CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Downforce Underbody Diffusor

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   January 10, 2012, 17:02
Default Downforce Underbody Diffusor
  #1
New Member
 
Philipp Bolay
Join Date: Jan 2012
Posts: 6
Rep Power: 5
Cola1988 is on a distinguished road
Hello Everybody,

I'm from a Formula Student Team and i'm simulation the aerodynamic concepts. At the time i'm simulating the underbody diffusor.
My problem is I can't display the downforce in Y-direction... It normally brings totaly unnormal values of about 50000N....

My Expression says: force_y()@underbody

underbody is the bottom surface ( I selected it as a separate part in ICEM) of the underbody...
Do i have to select gravity or somthing other?

Am i doing it wrong the hole way?
http://www.bilder-hochladen.net/file...xs-2c-9778.jpg

http://www.bilder-hochladen.net/file...hxs-2d-fe9f.jp
http://www.bilder-hochladen.net/file...xs-2e-68d3.jpg
Thanks and regards

Phil
Cola1988 is offline   Reply With Quote

Old   January 10, 2012, 18:25
Default
  #2
Senior Member
 
Edmund Singer P.E.
Join Date: Aug 2010
Location: Minneapolis, MN
Posts: 494
Rep Power: 10
singer1812 is on a distinguished road
Your picture is showing 0.5 N not 50000 N?
singer1812 is offline   Reply With Quote

Old   January 10, 2012, 20:39
Default
  #3
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,824
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
The force variable is not meaningful as you have shown it. What you are showing is the force on each element face, and the areaAve() function is giving the average force on a element - neither of which is meaningful as it changes with element size.

What you want to do is do an area integral of force over the surface. This will give you the total force on the body which is the number of physical importance.
ghorrocks is offline   Reply With Quote

Old   January 11, 2012, 10:00
Default
  #4
Senior Member
 
Edmund Singer P.E.
Join Date: Aug 2010
Location: Minneapolis, MN
Posts: 494
Rep Power: 10
singer1812 is on a distinguished road
I think Glenn mean areaInt of Pressure, unless I am mistaken.
singer1812 is offline   Reply With Quote

Old   January 11, 2012, 12:06
Default
  #5
New Member
 
Philipp Bolay
Join Date: Jan 2012
Posts: 6
Rep Power: 5
Cola1988 is on a distinguished road
Hey,

Thanks very much for your help! i don't know why i missed the equation for the pressure^^

The Problem is i'm getting really unnormal values..

for: areaint(pressure)@underbody = around 90000N ... That can't be true..

I calculatet it in the CFD post function calculator..
Do i have to set on gravity in CFX-pre?

The inlet is set to 22 m/s.

Thanks, Phil
Cola1988 is offline   Reply With Quote

Old   January 11, 2012, 12:43
Default
  #6
Senior Member
 
Edmund Singer P.E.
Join Date: Aug 2010
Location: Minneapolis, MN
Posts: 494
Rep Power: 10
singer1812 is on a distinguished road
Why would you need gravity?

Is the Underbody the entire structure shown in your picture or is it just one side of the structure.

If it is just one side, you need to include the other side because you are not including the backside pressure in your force calc.

Also another way to get your force out is force_y@Underbody or use force with axis y in the function calculator
singer1812 is offline   Reply With Quote

Old   January 11, 2012, 17:52
Default
  #7
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,824
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I meant the force_x/y/z functions. The areaInt function will return only the pressure component of the force and not the wall shear. Force gives you the total force. But it won't make much of a difference in this case, the pressure force should be just about all the force.

But if you are getting massive forces, what is your reference pressure? If you have a zero reference pressure the force on a surface like this would be massive. To fix this set the reference pressure to the local ambient pressure, or better still the pressure which acts on the other side of the diffuser (if different to ambient).
ghorrocks is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Workflow for F-1 Underbody aero simulation? t_money662 CD-adapco 3 June 24, 2009 05:17
wich program for internal flow / diffusor and ... Marko Main CFD Forum 1 April 29, 2004 17:41
Annular Diffusor Test Case Jonas Larsson Main CFD Forum 0 July 2, 2003 09:34
fully developed flow in diffusor Fabian CFX 1 September 19, 2001 18:13
Diffusor testcase Marat Hoshim Main CFD Forum 12 February 12, 2001 13:27


All times are GMT -4. The time now is 05:24.