CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLOW-3D

create waves

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   October 7, 2008, 09:21
Default create waves
  #1
aginor
Guest
 
Posts: n/a
how i can create sea waves? i what to make messurements about some forces. i find in the help: Example: Creating a Wave-Maker Type Boundary but i dont know what to do it
  Reply With Quote

Old   October 7, 2008, 10:59
Default I've simulated linear wave boundary
  #2
Byongjun Park
Guest
 
Posts: n/a
Do you mean simulating like this?

* http://cometrue.kr/66 : 2D Wave Flume * http://cometrue.kr/75 : 3D Detached Breakwater

I've simulated wave boundary with version 9.2, but it was linear wave.

The input file cannot be built up in GUI environment. To make wave boundary you must edit "prepin.inp" by text editor program like "NOTEPAD" or "Ultra Editor".

For example,

...

$bcdata

wl=6, iwavel=1, waveamp(1)=4., wavefre(1)=12.,

wr=8,

wb=2,

wt=5, pbct(1,6)=0., fbct(1,6)=0., $end

...

$fl

nfls=1,

fzh(1)=15., remark='initial water level', $end

...

If you want input "wavenum(n)" at left boundary, must delete "wavefre(n)".

Please refer to user manual, and good luck!

P.S. (1) If your solver is earlier than version 9.0, it may be define as time series boundary. (2) To make irregular wave boundary, you have to complie user subroutine with FORTRAN(Intel). The example source code is uploaded in FLOW-3D user site, but I didn't try it yet. (I'd like to compare with CADMAS-SURF.)
  Reply With Quote

Old   October 7, 2008, 11:43
Default Re: I've simulated linear wave boundary
  #3
MAB
Guest
 
Posts: n/a
Hi Byonggjun. I like your animations of wave's. I am going to use the new version9.3 for generating waves together with GMO model to calculate the rigid bodies displacement. i am sure your advice in modelling linear waves would very helpfull. Could you tell that what is the total time taken by flow-3D for these animations. are these 2D or 3D cases? Thanks MAB
  Reply With Quote

Old   October 7, 2008, 12:34
Default Re: I've simulated linear wave boundary
  #4
MAB
Guest
 
Posts: n/a
Also which package you have used to make this animations. Have you used Flow-3D postprocessor. or anyother package for making animations? Thanks

  Reply With Quote

Old   October 7, 2008, 15:26
Default Re: I've simulated linear wave boundary
  #5
aginor
Guest
 
Posts: n/a
Byongjun Park, i make several experiments but it doesnt work. can you sent me a very simple file with waves? one prepin file. and i will tray to make my change. i see your animation. very good work!!!!
  Reply With Quote

Old   October 7, 2008, 20:39
Default It taken 2D 13H 13M 52S.
  #6
Byongjun Park
Guest
 
Posts: n/a
In the case of "2D Wave Flume", it taken 2D 13H 13M 52S. In fact, the simulation was done by 3D. If the number of Y-Dir. grid set to 1, it might be over several hours.

My hardware Spec. - CPU : Intel(R) Core(TM)2 Quad CPU @ 2.66GHz - RAM : 8GB (2GB * 4) - OS : Microsoft Windows XP(64bit) - Ver. : 9.2.1 - I use SMP version. So it works parallel mode

Test Condition - Num. of grid : 1177600 - X=-100~100, Y=-4~4, Z=0~23 - Amplitude=2m, Frequancy=10.12sec - Mean water level=15m

P.S. I heard that version 9.3 can inport STL solid as GMO in post processing.

http://cometrue.kr/98 http://cometrue.kr/99
  Reply With Quote

Old   October 7, 2008, 20:45
Default I used "Flash Slider"
  #7
Byongjun Park
Guest
 
Posts: n/a
In order to upload result of simulation at my BLOG as animation, I used "Flash Slider".

You can download at this URL.

http://www.flashslider.com/download/fs_setup.exe

  Reply With Quote

Old   October 7, 2008, 20:56
Default Please send me your input file
  #8
Byongjun Park
Guest
 
Posts: n/a
Sorry, I don't know your e-mail address and how to attach achive files in this forum environment. If you send me your input file, I check & edit your input file and I will send modified input file.

P.S. I live in Korea(GMT+09:00).
  Reply With Quote

Old   October 8, 2008, 05:06
Default Re: It taken 2D 13H 13M 52S.
  #9
MAB
Guest
 
Posts: n/a
Thanks Byongjun!! I have same hardware as yours. How long it takes for 3D case? Are you using outflow boundary at outlet. What do you think about this outflow and Continuative boundaries? Many Thanks in Advance
  Reply With Quote

Old   October 8, 2008, 08:17
Default In order to consider reflection wave...
  #10
Byongjun Park
Guest
 
Posts: n/a
Because of reflection wave, I used outflow condition(8) with fluid height(mean water level) at right boundary.

I didn't try continuative condition, but I guess continuative condition can break reflection wave, too.

Now, I'm simulating the intake of power plant at Gunsan, Korea, so I cannot try to simulate the case of continuative condition. If you have spare time and can try it as 2D simulation, please tell me the comparison results. ^_^

I remember the simulation of detached breakwater(3D) required more times and that was my first simulation of 3D wave generating. Because I erased result file, I don't know elapsed time. But it was very interesting.
  Reply With Quote

Old   October 8, 2008, 13:04
Default Re: I've simulated linear wave boundary
  #11
kyunghwan
Guest
 
Posts: n/a
Hi,

This is wave make sample input for v9.2.

good luck!

---------------------------------------------------

RF01 T=1.4, H=0.05

$xput

remark='units are ...',

twfin=28., itb=1, gz=-9.80, ipdis=1,

apltdt=0.2, hpltdt=0.01, pltdt=100.,

delt=1.0e-4, dtmin=1.0e-10, autot=2.,

ifvisc=1, impadv=1,

ifvis=4, tlen=0.007,

igmres=1, $end

$limits

$end

$props

rhof=1000.,

mu1=0.001, units='si',

$end

$scalar

$end

&bcdata

wl=6, wr=8, flhtr=0.3,

wt=5,

fbct(1,6)=0.0,

flhtl=0.3,

iwavel=1, waveamp(1)=0.025, wavefre(1)=1.0, waveh(1)=0.45,

/

&mesh

nxcelt=2500,

nycelt=1, py(1)=0.0, py(2)=0.1,

nzcelt=50, px(1)=-8.0, px(2)=0.0, pz(1)= 0.0, pz(2)= 0.3, pz(3)=0.5,

px(3)=10.0, sizex(1)=0.0,

px(4)=17.0, px(5)=17.1, px(6)=17.2, px(7)=17.3,

px(8)=17.4, px(9)=17.5, px(10)=17.6, px(11)=17.7,

px(12)=17.8, px(13)=17.9, px(14)=18.,

/

$obs

avrck=-5.1,

$end

$fl

nfls=1, fzh(1)=0.3, flht=0.3,

$end

$bf

$end

$temp

$end

$motn

$end

$grafic

anmtyp(1)='f', anmtyp(2)='p', anmtyp(3)='vel',

anmtyp(4)='srfht',

$end

$parts

$end

------------------------------------------

  Reply With Quote

Old   October 10, 2008, 05:38
Default Re: I used "Flash Slider"
  #12
MAB
Guest
 
Posts: n/a
Thanks Byongjun !!! You used flash to upload your simulations .. but which package you used for making these animations, Flow-3D's postprocessor or TecPlot or something else.?

  Reply With Quote

Old   October 11, 2008, 20:48
Default Just making a animation...
  #13
Byognjun Park
Guest
 
Posts: n/a
When I made a animation from simulation results, I used post-precessor of FLOW-3D, but it had some time lag in case of large flame and couldn't change resolution.

So I used bmp2avi(It works in DOS prompt), I found some time lag, too. Receltly, I use img2avi. It works in Windows Env.

To batch resizing(changing resolution) of frame cuts, I use other freeware(I use PhotoWORKS).

Tecplot 360 2008, FieldView v12 are good post-processor for CFD, but these S/W are not require in case of making a animation, only.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
how to set periodic boundary conditions Ganesh FLUENT 13 January 22, 2014 05:11
Include list of points Hikachu OpenFOAM Native Meshers: blockMesh 0 June 20, 2011 09:03
Actuator disk model audrich FLUENT 0 September 21, 2009 07:06
Where's the singularity/mesh flaw? audrich FLUENT 3 August 4, 2009 01:07
fluent add additional zones for the mesh file SSL FLUENT 2 January 26, 2008 12:55


All times are GMT -4. The time now is 14:05.