CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

How to treat the jump-periodic boundaries with the fluent!please help me!

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 7, 2012, 09:46
Default How to treat the jump-periodic boundaries with the fluent!please help me!
  #1
New Member
 
Small Mayi
Join Date: Nov 2011
Posts: 26
Rep Power: 5
ChenZhan is on a distinguished road
Hello,everyone!
How to treat the Jump-Periodic boundary contions in the solution of solid and fluid thermal coupled problems in order to gain the effective conducitivity under the condition where there is no flow exist in the computational domain.
Since the filesize of this pape exceeds the limit of the forum, i can not upload the paper that i read.So just a URL is presented for you ,and i am very sorry for that.
Please help me,everyone!!
Tell me how to carry out this Special boundary condition with fluent?
Because no flow exist in the domain,the wall boudary condition is coupled wall, for the steady state,how to impose a temperature drop on the heat flow direction,i.e how to impose a temperature gradient on the periodic faces?
The paper i mentioned, which you can see using the URL,had presented the method and the discreted equation sets.But i can not understand how
to do the same work using the method, since a similar problem is under accounted for me.
please,help me!!thanks everyone!!
URL:http://asmedl.org/getabs/servlet/GetabsServlet?prog=normal&id=ASMECP0020044711Xa000 247000001&idtype=cvips&gifs=yes
Title:A Numerical Technique for Computing Effective Thermal Conductivity of Fluid-Particle
ChenZhan is offline   Reply With Quote

Old   May 7, 2012, 12:25
Default
  #2
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 594
Rep Power: 11
LuckyTran is on a distinguished road
Can't access the paper as it's from a conference proceeding and requires a purchase but I managed to find the paper myself through my own database. I skimmed through it, so my interpretations may be immature, if I am wrong on anything, someone please correct me.

I disagree with the author's calling it the equivalent of the constant heat flux periodic condition since that is not how the constant heat flux case is treated in Fluent and many other software/schemes. In these software, the jump discontinuity in the bulk temperature is not applied, rather the bulk temperature remains constant by solving the temperature gradient separately (because the heat flux is known). This difference will may the simulation difficult or maybe impossible in Fluent. Even more so, the authors specified a temperature gradient which is inconsistent. How can you specify a constant heat flux and also the temperature gradient?

To get the periodic heat transfer with no flow simply setup your case. Initialize the flow with 0 velocity everywhere. And disable the computation of the momentum equations (flow). Then the solver will only solve the energy equations. There may be some numerical errors associated with assigning a 0 velocity everywhere, since numerically 0 is just a very small number. Hence your results may be accrue some inaccuracies. You can use any viscous model since you are going to disable it anyway. But I suggest using a laminar model so that the turbulence modelling parameters don't add any more errors.

Unfortunately, if you enter a mass flow rate of 0 in Fluent, this may cause the bulk temperature gradient to blow up. The temperature gradient is calculated by dividing the total heat addition by the incoming heat capacity which is now 0.

The other problem is the constant bulk temperature. You won't have any conduction through your embedded solids since there is no temperature difference in the flow. Additioanlly since there is no flow, there is no net direction of heat transfer and no direction can be assumed for the temperature gradient. This is a conceptual mistake I believe on the authors part.

I am not completely familiar with this topic so I will suggest by asking questions. Does this problem require the use of periodic conditions? Can you not simply specify the fluid temperature at the inlet and exit (by making them static walls) and then solving the same problem? This is basically what the authors did by specifying a temperature gradient.

Last edited by LuckyTran; May 7, 2012 at 13:10.
LuckyTran is offline   Reply With Quote

Old   May 7, 2012, 22:53
Thumbs up Treatment of jump-periodic boundary with the fluent
  #3
New Member
 
Small Mayi
Join Date: Nov 2011
Posts: 26
Rep Power: 5
ChenZhan is on a distinguished road
Thanks,LuckyTran.
I am grateful for your help,and appreciate any information that you give me,especially for that you had download the paper and had a careful reading.
As we study the porous media on the microscopic scale(cell or representive element volume),which is a basic unit ,in order to replace the object of the
whole block material, a REV may be choosed to reduce the computation expense.So the periodic boundary condition may be more appropiate in this case.Just as you said,the same obfuscation is for me when i managed to solve the problem with the fluent.
Yes,you are right.The suggestion that setting the inlet and exit with the wall boundary condition ,rather than periodic boudary condition,may be a good idear.I will try it as you said.
At last, the paper that using the fluent solve this problem will presented for
you,please tell me how to interprete the meaning of that "Computations are performed using a modified version of the commercial code FLUENT(page 796)",at your convinience.
Titleirect Simulation of Transport in Open-Cell Metal Foam.
Author: Shankar Krishnan et.
Journal:Journal of Heat Transfer
URL:http://asmedl.org/getabs/servlet/GetabsServlet?prog=normal&id=JHTRAO000128000008000 793000001&idtype=cvips&gifs=yes
My email :chenzhana@163.com
Also,you can have this paper by message.
Very,Very Thanks for your help.
Have a nice day,My friend.Good luck.
ChenZhan is offline   Reply With Quote

Old   May 8, 2012, 00:06
Default
  #4
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 594
Rep Power: 11
LuckyTran is on a distinguished road
Quote:
Originally Posted by ChenZhan View Post
please tell me how to interprete the meaning of that "Computations are performed using a modified version of the commercial code FLUENT(page 796)",at your convinience.
The authors reference the Fluent user guide as to how it is implemented, that is a bit bogus and not very helpful. Additionally, the methodology that they reference is the earlier IMECE conference proceedings, where I have already pointed out some of the errors. So I cannot really comment on how the authors carried out their computation. At least you should understand the conceptual methodology. And at least it is known that it was definitely calculated using Fluent.

It might be of importance to note that, although the bulk temperature is maintained constant for the constant heat flux case, the periodic jump condition is applied for the constant wall temperature case.

I double checked and no changes were made to Fluent since version 6.0 so there is no way that the authors could've used the specified heat flux condition as that would have resulted in a constant bulk temperature which contradicts many points they made. I'm not sure what's going on here.

I understand the argument for periodic geometry but am not sure how that is applicable. Since we all agree that the temperature gradient is arbitrary anyway and no bulk fluid motion exists, so even setting the wall temperature is equivalent to a periodic heat transfer (if periodic heat transfer is even applicable, which it really isn't). I do however see how it is possibly doable by tricking Fluent into solving it (since you can input a direction vector so that Fluent can assume the flow is in a certain direction). A huge problem I imagine that would be encountered with Fluent is the spatial discretization scheme (which is either 1st or 2nd order upwind). For a stagnant flow there is no upwind cell (because there is no advection). There is a corresponding upwind cell in the heat diffusion sense, but that is not what Fluent is looking for when checking the upwind condition (it is looking for face velocities).
LuckyTran is offline   Reply With Quote

Old   May 8, 2012, 03:25
Default Treatment of jump-periodic boundary with the fluent
  #5
New Member
 
Small Mayi
Join Date: Nov 2011
Posts: 26
Rep Power: 5
ChenZhan is on a distinguished road
Thanks,Lucky Tran.
if this question could not be solved by the software fluent ,can you give me some suggestion on other software,as i am tenderfoot. I means that if there are some other open codes (free software,like openfoam),through making any modification by myself,can solve this problem,because i have another problem like this,which is about the mass transfer.
(species i mass diffusion flux enter the domain from the top boundary)
http://asmedl.org/getabs/servlet/GetabsServlet?prog=normal&id=ASMECP0020044711Xa000 365000001&idtype=cvips&gifs=yes
(species i mass diffusion flux enter the domain from the down boundary)
In order to simulation the situation of the full development, i manage to use the periodic boudary to solve this problem.But you know,in the fluent,its capability to solve the heat transfer and flow with some geometry repetition.
So if i want to solve it,what need i do ?
It is just the similar,and like this problem also present some other reasurech field.There are some common character that the upstream field informations were not known which need to impose the downstream(right side)informations on the upstream(left side),and continuously iterate until the difference between the upstream and downsteam keep a constant.
Thus how to treat these problems ?
Fluent can do?
Thanks a lot,my friend!
My english is poor,if some mistakes happened in the text,please tell me !
Thanks again!!!
Title:MACROSCOPIC MODELING OF TURBULENT MASS TRANSPORT IN HETEROGENEOUS POROUS MEDIA

Last edited by ChenZhan; May 8, 2012 at 03:37. Reason: append image
ChenZhan is offline   Reply With Quote

Old   May 8, 2012, 12:13
Default
  #6
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 594
Rep Power: 11
LuckyTran is on a distinguished road
For the case of no mass diffusion, it should still be treatable by taking the fluid to be a solid.

However, there should not be confusion between periodic geometry and periodic heat transfer. Sure I accept that the geometry is periodic but there is no need for the resulting heat transfer problem to also be periodic. Periodic heat transfer leads to very unstable results. So instead, I would apply an arbitrary temperature gradient which is what the aforementioned papers did anyway.

Also, no use of periodic boundary conditions need even be applied since they don't matter. The physical geometry is probably periodic, but the numerical simulation does not care as long as it has the proper boundary conditions (which we agree a simple temperature gradient will suffice).

Mass flux is not a periodic flow, so you must abandon the periodic approach! But I do not think that is much different than what you are attempting, since periodic bcs are not needed anyway.
LuckyTran is offline   Reply With Quote

Old   May 8, 2012, 21:11
Default Jump-periodic boundary
  #7
New Member
 
Small Mayi
Join Date: Nov 2011
Posts: 26
Rep Power: 5
ChenZhan is on a distinguished road
Thanks,Lucky Tran.
Yes,you are right, i agree with your opinion,especially on the species mass fraction.As we know, the conservation of mass,moment and energy.If the species l enter into the domain from any boundary ,that will cause the velocity field changing.The inlet and outlet could not keep the same profile
whether the fluid is a compressible one or not.Simutaneously,the mass variation will also cause the moment and energy changing.
Thanks very much again.
Take my best wishes to your family.Good luck!!
your friend:Chen Zhan
ChenZhan is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
periodic boundaries Mary FLUENT 10 January 9, 2014 23:09
CGNS import in fluent - periodic boundaries. Bjarne Børresen FLUENT 2 April 25, 2013 11:12
Why can't I make the boundaries periodic? Alina FLUENT 5 April 12, 2012 14:06
periodic boundaries - flow through a net PK FLUENT 0 July 12, 2007 11:58
Periodic Boundaries in GAMBIT!! swetha FLUENT 1 November 26, 2006 23:02


All times are GMT -4. The time now is 16:41.