# why in fluent report the skin friction coefficient is positive

 Register Blogs Members List Search Today's Posts Mark Forums Read

 October 25, 2012, 06:32 why in fluent report the skin friction coefficient is positive #1 New Member   Amir Join Date: Mar 2011 Posts: 9 Rep Power: 6 hi. why in fluent report the skin friction coefficient is positive in everywhere of separation zone?! while in separation zone the skin friction coefficient must be negative. please help me thanks for your attention

October 25, 2012, 06:44
#2
Senior Member

Join Date: Mar 2011
Location: Germany
Posts: 414
Rep Power: 11
Quote:
 Originally Posted by gomnam15010 hi. why in fluent report the skin friction coefficient is positive in everywhere of separation zone?! while in separation zone the skin friction coefficient must be negative. please help me thanks for your attention
Skin friction coefficient is always positive and what do you mean by separation zone?

October 25, 2012, 07:32
#3
Senior Member

Gonzalo
Join Date: Mar 2011
Location: Argentina
Posts: 108
Rep Power: 7
Quote:
 Originally Posted by gomnam15010 hi. why in fluent report the skin friction coefficient is positive in everywhere of separation zone?! while in separation zone the skin friction coefficient must be negative. please help me thanks for your attention
Be careful, because the criterion of skin friction (Cf) equals cero (not negative) to find flow separation only aplies when you have a 2D case like a 2D airfoil or a cylinder, but not in 3D cases like a wing.

October 25, 2012, 08:27
#4
New Member

Amir
Join Date: Mar 2011
Posts: 9
Rep Power: 6
Quote:
 Originally Posted by cfd seeker Skin friction coefficient is always positive and what do you mean by separation zone?

in the separation zone the velocity gradiant is negative and so the skin friction coefficient must be negative

October 25, 2012, 09:01
#5
Senior Member

Gonzalo
Join Date: Mar 2011
Location: Argentina
Posts: 108
Rep Power: 7
Quote:
 Originally Posted by gomnam15010 in the separation zone the velocity gradiant is negative and so the skin friction coefficient must be negative
But in which reference frame the velocity gradient is negative? May be FLUENT calculates the Cf with the absolute value of the wall shear, may be you must look at the components of wall shear and see if there is separation or not. regards
Gonzalo

 October 25, 2012, 09:37 #6 Senior Member     Paolo Lampitella Join Date: Mar 2009 Location: Italy Posts: 537 Blog Entries: 14 Rep Power: 17 The total wall shear stress used by fluent in defining the skin friction coefficient is, of course, a positive definite quantity (it is the magnitude of the total stress). Do what Gonzalo said and you will find what you're looking for.

 March 14, 2013, 02:27 #7 New Member   Manu Kamin Join Date: Nov 2011 Posts: 16 Rep Power: 6 I'm having the same problem here. The velocity vectors over the airfoil surface is clearly reversed(flow reversal). But then the skin friction coefficient plot is positive everywhere. I understand the possibility that Fluent might be using only the magnitude of wall shear stress to calculate the skin friction, hence it being positive everywhere. But of course, it is physically incorrect. So is there any option in Fluent by which I can get the actual physical skin friction coefficient plot?

 March 14, 2013, 03:22 #8 Senior Member     Alex Join Date: Jun 2012 Location: Germany Posts: 1,134 Rep Power: 19 It is not physically incorrect. The skin friction coefficient based on the wall sheat stress magnitude has to be positive. If you want negative values in recirculation zones, you will have to evaluate the components of the wall shear stress.

 March 15, 2013, 05:48 #9 New Member   Manu Kamin Join Date: Nov 2011 Posts: 16 Rep Power: 6 Hi Alex, Thanks for the response. However, Fluent seems to ignore the sign of even the wall shear stress. So there is no way for me to even evaluate cf from the wall shear stress by myself too. So how can I obtain negative cf in recirculation zones?

March 15, 2013, 06:33
#10
Senior Member

Alex
Join Date: Jun 2012
Location: Germany
Posts: 1,134
Rep Power: 19
Quote:
 Originally Posted by manukamin However, Fluent seems to ignore the sign of even the wall shear stress
I know for a fact that the streamwise component of the wall shear stress changes sign in a recirculation zone in reality and in fluent aswell.
What exactly are you simulating? Please post a picture of your setup with the orientation of the coordinate axes.

March 15, 2013, 09:36
#11
Senior Member

Join Date: Aug 2011
Posts: 315
Rep Power: 12
The wall shear stress is a a vector, it should have two components, say x-wall-shear & y-wall-shear in 2D simulation and three components in 3D simulation. Maybe there is something called "wall stress" which actually is the magnitude of wall stress vector, then you should look into the stress vector instead.

Fluent does do funny things. It reports the magnitude instead of the z-component of vorticity in 2D simulation.

Quote:
 Originally Posted by manukamin Hi Alex, Thanks for the response. However, Fluent seems to ignore the sign of even the wall shear stress. So there is no way for me to even evaluate cf from the wall shear stress by myself too. So how can I obtain negative cf in recirculation zones?

March 18, 2013, 09:04
#12
New Member

Manu Kamin
Join Date: Nov 2011
Posts: 16
Rep Power: 6

I'm simulating a flow problem in a 2-D compressor cascade. Hence my upper and lower walls are periodic.

I have attached an image of my meshed domain. Now the thing is that the wall shear stress is shown to be positive everywhere as per fluent (complete and not x and y). But I see that there are some recirculation zones when i plot the velocity vectors. Does that make sense? Or should I individually plot x and y wall shear stress?

I'm not sure how to display the co ordinate system. In Fluent are X and Y directions are as per a fixed global co -ordinate system or is it a local co-ordinate system that varies from point to point in which x is in the streamwise direction and y in the normal direction?

Attached Images
 periodic.jpg (51.3 KB, 53 views)

 March 18, 2013, 20:40 #13 Senior Member   Join Date: Aug 2011 Posts: 315 Rep Power: 12 X- and Y- directions are global coordinate system. The wall shear in Fluent is the magnitude of wall shear stress vector so that it is always positive. But the shear should approach to zero near the separation point. Then you can do a xy-plot to verify whether that the x-wall-shear change its sign around that point.

 March 19, 2013, 02:27 #14 New Member   Manu Kamin Join Date: Nov 2011 Posts: 16 Rep Power: 6 Well then my problem still persists! There is no way I can know if there is a recirculation zone if the shear stress plotted is always positive. Of course x and y shear stresses do have magnitude as well as a sign. But what's the point? They are as per a global co ordinate system. Since each element of my airfoil is oriented at a unique angle, there is no way that the x and y shear stress can tell me anything about streamwise and stream-normal shear stress. Unless, I create a custom function that resolves the x and y shear stress into streamwise and stream normal vectors at each element along the airfoil surface (wall).. But I'm not sure how to do that on Fluent.

 March 19, 2013, 02:46 #15 Senior Member   Join Date: Aug 2011 Posts: 315 Rep Power: 12 No, you don't have to do that. The skin friction goes to zero around the seperation point, so does its components and vice versa. You only need to guarentee that the transformation between the airfoil and the coordinate is non-singular. From the figure you provided above, the x-coordinate should well serve your purpose.

 Tags fluent 6.3.26, positive, skin friction coefficient

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Rif Main CFD Forum 4 March 9, 2010 11:52 john lynam Main CFD Forum 2 February 15, 2010 10:16 vinz OpenFOAM Running, Solving & CFD 98 October 27, 2008 09:43 Priyank Main CFD Forum 0 December 20, 2005 03:16 Alex Main CFD Forum 0 November 16, 2005 21:52

All times are GMT -4. The time now is 03:25.