# Heat transfer modeling with kOmegaSST at walls

 Register Blogs Members List Search Today's Posts Mark Forums Read

 November 23, 2012, 07:54 Heat transfer modeling with kOmegaSST at walls #1 Member   Sören Sander Join Date: Sep 2012 Location: Germany Posts: 43 Rep Power: 6 Hello everyone, I try to figure out, how the heat transfer through a wall is calculated in fluent when using the kOmegaSST model. Unfortunately, there is nothing given in the fluent manuel. Is the laminar flow equation used, because yPlus is around 1?

November 25, 2012, 20:12
#2
Senior Member

Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 1,372
Rep Power: 20
Quote:
 Originally Posted by Sören Sander Hello everyone, I try to figure out, how the heat transfer through a wall is calculated in fluent when using the kOmegaSST model. Unfortunately, there is nothing given in the fluent manuel. Is the laminar flow equation used, because yPlus is around 1?
Fluent uses an enhanced wall function appropriate for kOmegaSST model for all equations (including energy). If your mesh is sufficiently fine near the wall (y+ < ~10), then it is equivalent to using the the linear (laminar) model.

 November 26, 2012, 01:16 #3 Super Moderator   Sijal Join Date: Mar 2009 Location: Islamabad Posts: 4,314 Blog Entries: 6 Rep Power: 43 Yes, with Y+1 you are able to solve the laminar sublayer. Sören Sander likes this.

 November 28, 2012, 05:01 #4 Member   Sören Sander Join Date: Sep 2012 Location: Germany Posts: 43 Rep Power: 6 Thanks for your replys. However, now I have found another problem on this topic: I want to calculate the heat transfer coefficient. fluent can derive it automatically, but again I am not able to find the formulation. It should be h=(T_wall-T_inf)/q_dot, where q_dot=(T_wall-T_p)/dn where T_p is the temperature derived in the first cell from the wall and dn is the distance normal from the wall. What value does T_inf have? Is it the same as T_p? Is there any reference to validate how it is calculated?

November 28, 2012, 09:35
#5
Senior Member

Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 1,372
Rep Power: 20
Quote:
 Originally Posted by Sören Sander It should be h=(T_wall-T_inf)/q_dot, where q_dot=(T_wall-T_p)/dn where T_p is the temperature derived in the first cell from the wall and dn is the distance normal from the wall. What value does T_inf have? Is it the same as T_p? Is there any reference to validate how it is calculated?
T_inf should be the driving fluid temperature consistent with Newton's law of cooling. Things like freestream temperature, bulk temperature, recovery temperature are used to get the most physical value of h. T_inf is using nomenclature from low-speed external flows where the freestream temperature is the driving temperature. Otherwise the choice of T_inf is arbitrary as much as length scale is arbitrary in Reynolds number.

Last edited by LuckyTran; November 28, 2012 at 11:56.

 November 28, 2012, 11:34 #6 Member   Sören Sander Join Date: Sep 2012 Location: Germany Posts: 43 Rep Power: 6 So I can define T_inf in fluent?

November 28, 2012, 11:58
#7
Senior Member

Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 1,372
Rep Power: 20
Quote:
 Originally Posted by Sören Sander So I can define T_inf in fluent?
Oh yes. T_inf is a user supplied input. It is the reference temperature that is user specified in the reference values. It is specified as a constant. If you want to use a variable T_inf you will need to modify the fluent code (use a UDF).

The wall heat flux and surface temperature are determined from the solution. The heat transfer coefficient is then calculated by applying Newton's law of cooling and using Tref (the reference temperature specified in the reference values).

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post l.te CFX 2 May 17, 2014 23:45 Anna Tian Main CFD Forum 4 October 9, 2012 15:12 Chander CFX 2 May 1, 2012 20:11 eryan STAR-CD 0 September 28, 2010 13:14 Mark FLUENT 1 May 13, 2003 04:23

All times are GMT -4. The time now is 05:19.