
[Sponsors] 
December 8, 2012, 14:06 
laminar to turbulent transitions

#1 
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
hi dear friend
i have 2 question (PLZ) 1.how can i define the wall spacing to the first grid point from an airfoil surface in ansys? 2.how can i partition my computational grid into to two zones to predict laminar to turbulent transitions ? 

December 9, 2012, 07:57 

#2  
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 414
Rep Power: 11 
Quote:
Quote:


December 9, 2012, 07:57 

#3  
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 414
Rep Power: 11 
Quote:
Quote:


December 9, 2012, 09:38 

#4  
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
Quote:
i am using ansis workbench for a structured grid can you help me for a better software? i want survey laminar separation bubble at low angle of attack on an airfoil with SpalartAllmaras model, in this condition a laminar to turbulent transitions occurs 

December 9, 2012, 11:24 

#5  
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 414
Rep Power: 11 
Quote:
Quote:


December 9, 2012, 13:07 

#6  
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
Quote:
Re is 100000 i want model Laminar separation on airfoil that Continues to turbulent i try to do this: "Simple RANS modeling lacks the ability to accurately predict laminar to turbulent transitions. It is typical that when using RANS modeling, the transition location is specified by the user. In FLUENT, this was done by partitioning the computational grid into to two zones. The location of the partition varies depending on the location of the laminar separation, which is analogous to the angle of attack to the airfoil. The partition is placed at the location that causes the greatest aerodynamic performance loss while still forming the separation bubble for each selected angle of attack." 

December 10, 2012, 02:10 

#7  
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 414
Rep Power: 11 
Quote:
I have already told you that now fluent has incorporated two new RANS turbulence models which are capable of capturing laminar to turbulent transition. Read the Theory/ Modelling guide of Fluent 12 and onwards, you will find a nice materials on these turbulence models. Do concentrate on reading especially the grid requirements for these models which are obviously the difficult part in the process 

December 11, 2012, 16:05 

#8 
New Member
Ebrahim
Join Date: Mar 2010
Posts: 18
Rep Power: 7 
Hi Amir
1. if you want to find it in your solver(for example FLUENT), and if you use a turbulence model, you can easily find the distance of near wall cells to the walls by using the known values of u_star and y_plus. 2. do you want to partition it before solving the flow or during the flow solution? in other words, do you know the boundary of the 2 partitions? 

December 29, 2012, 05:38 

#9  
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
Quote:
tanx for your answer 

December 29, 2012, 13:05 

#10 
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,914
Blog Entries: 6
Rep Power: 38 
I have done some projects on the Low pressure turbine transition prediction and passive control of separation (see the signature below) and got good resutls.
Now I am working on the validation of three equation model (K, Kl, w aka walter's model) and SST transition model (4 eq). I usually follow these guidelines: 1. Walter model gives the laminar to turbulent transition in very less no of iterations. order of 1 to 2 no of iterations was observed 2. Walter model works satisfactorily in steady state mode. 3. Use second order equations for all turbulence quantities including momentum equation. 4. Atleast 40 (may be up to 100) nodes in side boundary layer are needed along with streamwise mesh refinement at the expected location of transition. Keep the expansion rate below 1.15. 5. For the prediction of vortex shedding inside the boundary layer and downstream use the fine time step (order of 1 to 10 microsecond) 6. Use the flat plate turbulent boundary layer formulae to estimate the first cell height (Y+) and total boundary layer thickness. This step needs some trail and error. 7. Keep in mind laminar boundary layer is thinner than the turbulent boundary for same Reynolds number (considering the point 6). Also boundary layer thickness is inversely proportional to Reynolds no. 8. You dont need the two zones. 

December 30, 2012, 03:33 

#11  
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
Quote:
I want model flow over on a s809 airfoil @ some angle off attack from 2 to 20 Should i predict laminar to turbulent transition location for low angle? 

December 30, 2012, 05:19 

#12 
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,914
Blog Entries: 6
Rep Power: 38 
but at higher angles still you have laminar flow at leading edge ! isnt it?
If at the higher angles transition models fail, so do the base line two equation models. You may be required to run the case as unsteady at higher AOA 

December 30, 2012, 06:50 

#13  
New Member
amir
Join Date: Dec 2012
Posts: 29
Rep Power: 4 
Quote:
can any turbulence models in fluent model this flow at all angle of attack? with spalartallmaras model i should specify transition location but i have't this data for 10^5 Re. can you help me about this and "Walter model"? 

December 30, 2012, 06:55 

#14 
Super Moderator
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,914
Blog Entries: 6
Rep Power: 38 
Here we have used SST gamma theta model
http://asmedl.org/getabs/servlet/Get...ifs=yes&ref=no Now I am applying the walters model and will show you some results. As far settings are concerned I have already mentioned above and there is no constant which you need to set for this model. 

Tags 
partition, transitions 
Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Laminar doesn't converge; Turbulent models do?  Amit  FLUENT  11  April 23, 2015 22:55 
CFX Treatment of Laminar and Turbulent Flows  Jade M  CFX  6  January 26, 2013 11:11 
Problem with divergence  TDK  FLUENT  10  September 8, 2012 01:11 
SimpleFoam: Laminar vs. Turbulent Convergence  JasonG  OpenFOAM  0  June 2, 2011 08:29 
Laminar vs Turbulent NavierStokes  truman  Main CFD Forum  6  March 7, 2011 14:44 