|
[Sponsors] |
August 14, 2014, 08:20 |
Jet combustion issue
|
#1 |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
Hello,
I am trying to run a combustion simulation for kerosene in the combustion can of a small turbojet engine. The main problem I've found is that there doesn't seem to be any combustion taking place. I have used a few tutorials and read a manual or two but it seems to me like the fuel isn't actually burning. In fact, it seems like nothing is happening (temperature field not changing). I have attached a screenshot of the can mesh and any help would be appreciated. Thank you |
|
August 18, 2014, 08:08 |
|
#2 |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
Bump. Still no joy :/
|
|
August 23, 2014, 19:46 |
|
#4 |
New Member
Join Date: Jun 2011
Posts: 22
Rep Power: 14 |
Is your simulation steady state or transient? Did you make sure you are solving for species transport? Did you enable volumetric reactions? If so what turbulence-chemistry interaction are you using?
Additionally, in order to initiate the reactions you need to.precribe an initiation patch with high temperature and appropiate species concentration. |
|
August 23, 2014, 20:42 |
|
#5 |
Member
Join Date: Feb 2013
Posts: 60
Rep Power: 13 |
I am running transient combustion models with a spark ignition. How are you igniting the mixture?
|
|
August 24, 2014, 09:40 |
|
#6 |
New Member
Join Date: Jun 2011
Posts: 22
Rep Power: 14 |
I first mark a region of the domain where I expect the flame to be. Then I patch that region with a high temperature value and species mass fraction corresponding to the combustion products.
The value for temperature and mass fractions can be based on adiabatic flame calculations or chemical equilibrium calculations. |
|
September 8, 2014, 11:20 |
|
#7 |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
Hi everyone.
Thank you for all your replies and sorry I have taken so long to respond. I came across this issue previously but I think FLUENT will burn the mixture of air and fuel as soon as they come into contact in my model. I'm not very good at the combustion side of it in general but when I am setting up non-premixed combustion, I am asked to generate a pdf table - I think this constitutes part of the solution system for combustion because it asks for a new table every time I make a change (adiabatic setting, species mass fractions, etc). The reason nothing was burning previously was something in the way the boundary conditions were set up, I've now changed that around and I ran it a few times, playing around with URFs and solution methods until it wasn't reporting any errors but not converging either. I looked at the solutions and the temperature fields look like combustion is in fact taking place. I understand that there might be transient effects at work here - I am running a steady state simulation as far as I know. I'm gonna attach a shot of one of the residual plots to give you an idea of what I'm saying. |
|
September 8, 2014, 11:24 |
|
#8 |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
Some more information on the model
|
|
September 9, 2014, 09:57 |
|
#9 |
Senior Member
François Grégoire
Join Date: Jan 2010
Location: Canada
Posts: 392
Rep Power: 17 |
According to Fluent Users Guide 15.0, section 16.2.5: "An RFL (rich flamability limit) value of approximately twice the stoichiometric mixture fraction is appropriate." Did you verify your value?
I use low URFs in order to obtain convergence for combustion: pressure, density, momentum => 0.2 k, epsilon, turb. viscosity => 0.5 temperature, mixture fraction/variance => 0.9 Start with low URFs then increase them. |
|
September 9, 2014, 10:02 |
|
#10 | |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
Quote:
Been playing around with solution schemes and URFs today and its getting closer to the convergence criteria. Any other tips from anyone? |
||
September 9, 2014, 10:09 |
|
#11 |
New Member
Join Date: Jun 2011
Posts: 22
Rep Power: 14 |
Do not limit yourself to check the residual in order to determine convergence. Make sure that the total mass and energy balance is appropriate. Additionally I would place monitor probes in the flame region to verify that the velocity, temperature and main specie do not change significantly with the iterations.
|
|
September 9, 2014, 10:14 |
|
#12 |
New Member
Ahmed
Join Date: Mar 2014
Posts: 16
Rep Power: 12 |
I have looked at the results from previous simulations where it didn't converge and it looks 'correct' (as expected). The temperature and flow fields look correct, I think my issue is now with trying to get more accurate results.
|
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Modelling Combustion in Porous Zone | tanjinjack | FLUENT | 2 | September 26, 2016 04:10 |
2-D coal combustion -burnout issue | sam | FLUENT | 1 | November 1, 2013 00:35 |
hydrocarbon gases + Boron particle combustion | nileshjrane | OpenFOAM | 1 | December 13, 2010 06:20 |
high temperature jet flow converge issue. | universez | OpenFOAM Running, Solving & CFD | 0 | October 5, 2010 17:00 |
Combustion modeling | SuperPahan | CFX | 6 | September 9, 2010 11:57 |