CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

Turbulent viscosity

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   November 3, 2000, 00:43
Default Turbulent viscosity
  #1
rafat
Guest
 
Posts: n/a
Dear all, I am trying to simulate a flow over a building in 2D. although the solution converged, I still recieve a message says that the turbulent viscosity ratio over the limit 1e5. I will be glad to hear any suggestions

best regards,

rafat
  Reply With Quote

Old   November 3, 2000, 01:25
Default Re: Turbulent viscosity
  #2
John C. Chien
Guest
 
Posts: n/a
(1). You need to find out whether the solution you obtained is good, accurate, or mesh independent. (2). How do you simulate flow over a building in 2-D? I have never heard of a 2-D building. (3). Anyway, you need to pay attention to the mesh, and the Y+ constraint next to the wall. (Assuming that you are using the standard k-epsilon turbulence model, then the Y+ next to the wall must be in the universal log-law profile region.)
  Reply With Quote

Old   November 6, 2000, 18:54
Default Re: Turbulent viscosity
  #3
Sung-Eun Kim
Guest
 
Posts: n/a
I suggest you plot (contour) the turbulent viscosity ratio in the domain and see where it exceeds 10**5. In fact, the value of 10**5 doesn't have much meaning (After all, turbulent viscosity is an artifact). We could've set it to 10**6. It's just a reminder that somewhere, in the domain, turbulent viscosity is very high. Chance is that the solutions are not fully converged, even though the residuals seem low enough. Try tighter convergence criteria. It may be due to unrealistically high turbulence intensity you're using at the inlet boundary.
  Reply With Quote

Old   November 7, 2000, 06:04
Default Re: Turbulent viscosity
  #4
Volker Pawlik
Guest
 
Posts: n/a
Hi,

lately I got the same message (for a not negligible amount of cells) in a flow with mixed convection (forced and free). In my case it helped to change the discretization scheme for pressure from 'body force weighted (bfw)' to '2nd Order', to perform some hundred iterations and then to switch again to bfw.

In another case I tried to get rid of that mesaage by refining the grid where high values of the viscosity ratio occured. Unfortunately it did not help in this situation.

Maybe decreasing the viscosity relaxation factor could help the prevent the solver from "creating" to much turbulence respectively turbulent viscosity.
  Reply With Quote

Old   November 8, 2000, 00:11
Default Re: Turbulent viscosity
  #5
rafat
Guest
 
Posts: n/a
> Dear Sung-Eun Kim,
: Thank you for your great advice. Actually, I set k-e equal to 1 at the
: inlet which I presume it is a littel bit high.
: Again I appreciate your recommendations and I will take for sure as aguid
: lines to my work in the future.
:
: Best regards,
:
: Ra'fat Al-Waked
:
:
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
reversed flow at pressure inlet and turbulent viscosity is limited.... cfdiscool FLUENT 10 June 10, 2015 06:15
k-epsilon problem: non-physical turbulent viscosity production in coaxial free-jet Felipeb Main CFD Forum 1 July 26, 2010 17:02
Turbulent viscosity and shear rate shib FLUENT 0 June 22, 2010 12:44
setting value of turbulent intensity and turbulent viscosity ratio in wind tunnel nuimlabib Main CFD Forum 0 August 4, 2009 00:05
Problem of Turbulent Viscosity Ratio Limited David Yang FLUENT 3 June 3, 2002 06:13


All times are GMT -4. The time now is 19:46.