CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

Gas-Solid flow

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 21, 2004, 10:46
Default Gas-Solid flow
  #1
HDZ
Guest
 
Posts: n/a
We are trying to simulate gas solid flow in a certain geometry. We are having serious problems with convergence.

As a result, we reverted to trying a very simple case of solid and gas flowing down a vertical pipe. Still convergence is not easy at all. We have tried a combination of boundary conditions, velocity inelt/outflow; velocity inlet/pressure condition at the outflow, pressure/pressure B.C. We managed to get convergence at solids fraction of 10%. However, such a simple problem cannot converge at higher solids volume fraction.

We are using Eulerian-Eulerian model.

Is there anyone solving gas-solid flow problems? Can some one shed some light on this problem using FLUENT?

Thank you
  Reply With Quote

Old   March 21, 2004, 14:10
Default Re: Gas-Solid flow
  #2
ap
Guest
 
Posts: n/a
I'm working on the Eulerian granualar model too. I obtained satisfactory results on some risers with a solid volume fraction of 0.2 (20%).

I used velocity inlet and outflow boundary conditions.

I also met some convergence difficulties at the beginning, but these were related to solver settings.

I need more details of your problem to give precise information (sorry for all questions):

- Are you using the kinetic theory to model the granular flow? If yes, which correlation for viscosity?

- Which drag factor are you using?

- Which values of under-relaxation factor are you using?

- What kind of grid and what discretization scheme?

- If you model turbulence, how do you do it?

Hi

ap
  Reply With Quote

Old   March 22, 2004, 15:22
Default Re: Gas-Solid flow
  #3
AAK
Guest
 
Posts: n/a
-Yes we are using kinetic theory; gidaspow correlation is used for viscosity.

-We are trying all the available correlation.

-0.1 is the under-relaxation factor for all .

-Tetrahedral mesh is used

-The flow is laminar.

Our case is a steady state, solid and gas are both coming to the pipe inlet and leaving from the outlet.

I'm wondering if the gas/solid flow in steady state conditions is possible to be solved by available codes.

Thank's
  Reply With Quote

Old   March 22, 2004, 17:24
Default Re: Gas-Solid flow
  #4
ap
Guest
 
Posts: n/a
Gas-solid flows are not steady. The presence of the gas phase causes fluctuations in the flow, and particles form clusters. So, you should simulate your system using unsteady calculation. In the literature usually a time step between 5x10^-4 and 10^-5 is used (Gidaspow (1992) - Arastoopour (2000)).

- Under-relaxation factors seem too low to me: try 0.6 for pressure, 0.4 for momentum and leave 0.2 (or try to increase to 0.4) granular temperature and volume fraction.

- Make sure your grid is fine enough (If possibile, switch to hexa). Use the second order upwind (or higher) discretization scheme for convective terms. Do not use symmetry boundary conditions: it has been demostrated that these conditions cause unphysical cluster formation.

- I obtained results in better agreement with experimental data using Syamlal O'Brien correlation for both drag and viscosity.

Hope this helps

Hi

ap
  Reply With Quote

Old   March 23, 2004, 14:04
Default Re: Gas-Solid flow
  #5
AAK
Guest
 
Posts: n/a
ap

Thanks for your inputs. I'm using them and every thing is working fine,up to now.

I have concern regarding the computational time, from your experience, in general how long it will take to get some results.
  Reply With Quote

Old   March 23, 2004, 18:06
Default Re: Gas-Solid flow
  #6
ap
Guest
 
Posts: n/a
Well, it's strictly related to the dimension of your computational domain and on your computational resources.

However, on a P4, you should obtain results in a few days.

In one of my cases I simulated a system with a grid formed by about 35.000 nodes (hexa grid), for 60 seconds in about a week on a 2.5 GHz P4 workstation.

Hi

ap
  Reply With Quote

Old   March 24, 2004, 17:46
Default Re: Gas-Solid flow
  #7
aak
Guest
 
Posts: n/a
ap,

I really appreciate your help.

AAK

  Reply With Quote

Old   March 25, 2004, 16:34
Default Re: Gas-Solid flow
  #8
ap
Guest
 
Posts: n/a
You're welcome

ap
  Reply With Quote

Old   September 8, 2010, 02:02
Default Gas solid flow
  #9
New Member
 
PP
Join Date: Jul 2010
Posts: 9
Rep Power: 7
pandaba is on a distinguished road
Hi ap,

I am also working on gas solid flow. Your post helped me in convergence . I am getting the right profile for gas velocity variation.But for solids , the velocity plot shows zero value .


I am not able to find out the cause. Please help me.

Regards
Pandab
pandaba is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
gas flow out of a C-D channel ljp FLUENT 0 March 7, 2011 15:32
Gas Solid Fluidization ANKW FLUENT 1 November 21, 2009 11:13
Dispersed Solid particles in carrier gas (DPM) Frederik FLUENT 1 June 3, 2008 05:13
About gas flow and buildings Andreas Main CFD Forum 1 October 25, 2001 13:37
gas flow thougth water Roued Main CFD Forum 1 October 11, 2001 09:50


All times are GMT -4. The time now is 19:42.