CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

1st - 2nd order - convergence

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 15, 2004, 13:04
Default 1st - 2nd order - convergence
  #1
antonio
Guest
 
Posts: n/a
Hi everybody, I'm running a simple 2D simulation. A cylinder (D=1 m) is placed on the ground (contact point in x=0, y=0). Air is entering the domain at 10 m/s. The domain is: [(x=-3 to 5), y=0 to 4]. Viscous model: Laminar.

I Run a simulation with the following scheme: [Pressure: Standard; P-V Coupling: SimpleC; Momentum: First Order Upwind] and the problem easily finds a convergence (1e-06).

If I change Momentum to [Second Order Upwind], the continuity residual shows an oscillatory behaviour at around 1e-04.

Do you have an idea what is this due to? Thank you very much,

antonio
  Reply With Quote

Old   December 15, 2004, 13:15
Default Re: 1st - 2nd order - convergence
  #2
Jason
Guest
 
Posts: n/a
It's an unsteady problem. Bluff bodies are notoriously difficult to converge, especially cylinders because they lack a defined separation point. If you monitor your forces they'll oscillate as well. Your lift will have a regular oscillation while the drag looks more random, but still has underlying periodicity. If you plot your velocity vectors every so many iterations you'll notice the uneven vortices being shed by the body.

You can try switching to the coupled solver, with 2nd order discretization on flow. Since it's a density based solver, sometimes it can flatten out those oscillations. It's not a sure fix though.

I hope this helps.

Goodluck, Jason
  Reply With Quote

Old   December 15, 2004, 17:38
Default Re: 1st - 2nd order - convergence
  #3
antonio
Guest
 
Posts: n/a
thank you very much. I monitored lift and drag coefficients and they do oscillate quite regurarly. Do you know if there is a way to relate the frequency of the "numerical" oscillation to the physical frequency?
  Reply With Quote

Old   December 16, 2004, 09:21
Default Re: 1st - 2nd order - convergence
  #4
Jason
Guest
 
Posts: n/a
I've never been able to... I've been asked a few times to do that, but I haven't found a way to do it. If you do find a way can you post it on here?

If you've got the time, I would try running an unsteady solution. You can pull frequencies out of that.

Goodluck, Jason
  Reply With Quote

Old   December 16, 2004, 09:37
Default Re: 1st - 2nd order - convergence
  #5
he
Guest
 
Posts: n/a
I would not waste time trying steady simulation on an unsteady flow problem. Why don't you switch to the unsteady solver which is just a few buttons away?

(1) Choose the second-order temporal scheme (2) Use SIMPLEC (3) Estimate time-step size based on, say, strouhal number of 0.2 such that would give scores of (>20) time steps in a period (4) Jack up the under-relaxation factors (e.g., 0.9 and 0.95 for pressure and momentum respectively) (5) Monitor and write CD and CL history (6) Use the built-in FFT capability in FLUENT
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Limiters for 2nd order solvers Heinz Wilkening Main CFD Forum 1 March 14, 2013 04:40
Order of accuracy: 1st or 2nd order? fisch OpenFOAM Running, Solving & CFD 2 July 6, 2011 04:37
First order in time and Central Difference Convergence problem RameshK Main CFD Forum 7 July 17, 2010 14:13
In what range should the observed order of grid convergence be? jack1980 FLUENT 0 March 9, 2010 10:59
2nd order divergence Reg FLUENT 1 May 17, 2005 03:08


All times are GMT -4. The time now is 04:38.