CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

Cannot import ANY ICEM hex core into Fluent v6.3!!

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   October 5, 2007, 17:29
Default Cannot import ANY ICEM hex core into Fluent v6.3!!
  #1
Robert Perry
Guest
 
Posts: n/a
Hey everyone,

I am trying to hex-core mesh in ICEM v11.0.1. While the hexcore works beautifully, even on complicated geometries, I cannot import any form of hex core into Fluent, no matter how high the mesh quality is. I have even tried a simple cube and that fails with the following errors:

12494 nodes.

40882 mixed cells, zone 5. Error: read: face 85032, zone 6. Reading Faces: failed while reading section 13.

Clearing partially read grid.

Error: Read aborted due to critical error. Error Object: ()

Here is a pic of the cross section of the mesh where that error originated. I am using Fluent 6.3. I have tried windows and Linux.

http://www.calpoly.edu/~rperry/Icem%20Hex%20Core.PNG

In that pic there is only one set of surfaces, which I set as pressure-far-field for import into Fluent. I selected FluentV6 as my solver and output as a .msh. I have also tried generating a tet mesh and turning it into a hex mesh afterwards, but got the same errors.

I have no idea what could be going wrong, but any help would be very greatly appreciated!!

Cheers,

-Robert
  Reply With Quote

Old   October 5, 2007, 17:30
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #2
Robert Perry
Guest
 
Posts: n/a
http://www.calpoly.edu/~rperry/Icem%20Hex%20Core.PNG
  Reply With Quote

Old   October 6, 2007, 09:06
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #3
Joe
Guest
 
Posts: n/a
I believe this was discussed recently ... its apparently a bug in fluent(windows). Search the forum ...
  Reply With Quote

Old   October 6, 2007, 11:44
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #4
Robert Perry
Guest
 
Posts: n/a
I have also tried doing it in 32 and 64 bit Linux, so I think it's more than a bug?!~
  Reply With Quote

Old   October 7, 2007, 06:49
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #5
Joe
Guest
 
Posts: n/a
What do Fluent support say?
  Reply With Quote

Old   October 7, 2007, 07:55
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #6
Joe
Guest
 
Posts: n/a
I have duplicated your problem on linux64 (Icemcfd + fluent 6.3).

"Read aborted due to critical error"

> Reading "/home/fluent.msh"...

19342 nodes.

50796 mixed cells, zone 7. Error: read: face 112020, zone 8. Reading Faces: failed while reading section 13.

Clearing partially read grid.

Error: Read aborted due to critical error. Error Object: #f

Error: Error reading "/home/work/dynamic/Fluent/trialrun/2D/geom/krishnan/2dofsimple/delmenow/fluent.msh". Error Object: #f

However, there are workarounds. I exported the mesh for CFX11, created a basic CFX11 def file (mesh + BC specifications), imported this into fluent. This worked and solved fine.

Icemcfd has a myriad of export options, fluent has a myriad of import options. Somewhere the twain should meet.

Let us know how you get on.
  Reply With Quote

Old   October 7, 2007, 13:43
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #7
Robert Perry
Guest
 
Posts: n/a
Well, I had a friend try the CFX thing, and it didn't work either!

Error: bad syntax. Usage: utility fe2ram dimension read_format zoning write_format [inputfile [outputfile]] utility fe2ram dimension read_format zoning write_format [inputfile [outputfile]]

dimension: [-d2 | -d3 | -surface]

Building...

grid, Error: Null Domain Pointer

I'll contact Fluent and ICEM tech support and see what they say. I'll be sure to post the results here.

Thanks Joe!
  Reply With Quote

Old   October 7, 2007, 15:14
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #8
red lemon
Guest
 
Posts: n/a
convert hexcore mesh into polyhedra using utility tpoly so it becomes conformal grid then read into Fluent. This is the rec procedure for TGrid exported hexcore meshes for running in Fluent parallel.
  Reply With Quote

Old   October 7, 2007, 15:16
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #9
Robert Perry
Guest
 
Posts: n/a
What do I do if I don't have Tgrid? This is also a serial job, not parallel.

There has to be something wrong with Fluent/ICEM, because I can import hex-core from Gambit without using tpoly, and even run it in parallel (though it scales poorly).
  Reply With Quote

Old   October 8, 2007, 06:45
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #10
Sushil
Guest
 
Posts: n/a
Have you defined "Body" for your mesh in ICEM...It can be one of the resons for "Null Domain Pointer - Error.." just check it out...!
  Reply With Quote

Old   October 8, 2007, 13:05
Default Re: Cannot import ANY ICEM hex core into Fluent v6
  #11
Robert Perry
Guest
 
Posts: n/a
Well, here's what Fluent tech support said:

FLUENT ADMINISTRATOR: ----------------------------------------------------- There is a bug with ICEM - Fluent translator in ICEM 11, and when you see the section f error, it is because of this bug. So I will suggest you to use other version of ICEM with latest version of Fluent (6.3.26 version). If this does not work then please try following workarounds

1) You may write your ICEM mesh in ASCII format rather than Binary format (default?). We have seen that files written in ASCII format reads fine in Fluent with out any errors. 2) (a) Read (import) your ICEM mesh in GAMBIT using (File -> Import -> Mesh, Fluent5/6, 3d). (b) Export the mesh from Gambit (File -> Export -> Mesh) (c) Read this mesh in Fluent

One advantage here is that GAMBIT will retain all Boundary definitions you have made in ICEM intact. 3) You can try to export a CGNS file from ICEM, and read it in Fluent. However, this way we will loose the naming convention we have used in ICEM mesh. Also please note that files written in binary format are not transferable between Unix and Windows systems.

ME: ----------------------------------------------------- Thanks for the reply! I tried all your suggestions. Here are the results:

1.) By writing in ASCII I received the same errors.

2.) Gambit was not able to read in the mesh. I created a simple mesh of a cube in Gambit, exported it as cube.msh, and then imported it back in without problems. But for any ICEM grid import I got the following errors:

Quote:
Originally Posted by Gambit
import uns "/home/aero/Desktop/test.msh" angle 135 d3 scale 1 \ Reading |utility fe2ram -m1e-06 -d3 -tRAMPANT -oFIDAP7 /home/aero/Desktop/test.msh (feature angle = 135) ERROR: Error encountered while reading the header information. Makre sure that correct mesh dimension and type has been supplied. Gambit is unable to import. Process completed with exit code 256.
Could this be because I am using 64 bit Linux, and Gambit is a 32 bit program? If that's the case, I will try to get a 32 bit windows install and see if it works then, and post the results. I did check 3-D for the grid import, etc.

3.) Exporting to CGNS in ICEM did work, and Fluent read the mesh in fine. However, it did lose the naming conventions. I'd really like the get the gambit method to work, as I will be doing automated studies, so I need the names to match!
  Reply With Quote

Old   April 12, 2012, 04:30
Default How to sovle the same problem
  #12
New Member
 
Jecci Gao
Join Date: Oct 2011
Posts: 2
Rep Power: 0
atheism is on a distinguished road
Quote:
Originally Posted by Robert Perry
;145981
Well, I had a friend try the CFX thing, and it didn't work either!

Error: bad syntax. Usage: utility fe2ram dimension read_format zoning write_format [inputfile [outputfile]] utility fe2ram dimension read_format zoning write_format [inputfile [outputfile]]

dimension: [-d2 | -d3 | -surface]

Building...

grid, Error: Null Domain Pointer

I'll contact Fluent and ICEM tech support and see what they say. I'll be sure to post the results here.

Thanks Joe!


I faced the same situation, but I figure out. There was a wrong path where you saved the file. Change it !
atheism is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Superlinear speedup in OpenFOAM 13 msrinath80 OpenFOAM Running, Solving & CFD 18 March 3, 2015 06:36
Problem in IMPORT of ICEM input file in FLUENT csvirume FLUENT 2 September 9, 2009 01:08
Exporting ICEM Tetra Grid to Fluent with Hexa-Core Tim FLUENT 2 August 30, 2007 07:16
Exporting ICEM Tetra Grid to Fluent with Hexa-Core Tim Main CFD Forum 4 August 28, 2007 04:05
ICEM CFD 10.0 cannot import Tecplot mesh!!! yi CFX 1 February 13, 2006 06:07


All times are GMT -4. The time now is 10:41.