CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

DPM in cyclone separator!!

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By Allan Walsh

Reply
 
LinkBack Thread Tools Display Modes
Old   February 4, 2008, 17:46
Default DPM in cyclone separator!!
  #1
Ines M
Guest
 
Posts: n/a
I'm working on cyclone separators gaz-solide (CFD simulation, Fluent), I found an article published in Elsevier and I considered it useful to validate my model, basing myself on its results, but now I have two big problems which prevent me from continuing my work:

•The first problem: Distribution of particles: ROSIN-RAMMLER distribution with a min diameter 2e-07 (m), max diameter 0.0001 (m), mean diameter 2.99e-05 (m), spread parameter 0.806 and number of diameters 5 (type of injection: surface). Results: when I did particle tracks, I carried out that diameters chosen by Fluent are 2e-07, 2.5e-05, 5e-05, 7.5e-05, 1e-04 => in comparison with results of the article, I found a great difference; diameters schematized in the article are about 1e-06 (the diameters selected influence the performances of the cyclone and separation efficiency since particles having diameters about 1e-05 keep spinning near the wall at a certain horizontal level.

•The second problem: I do not manage to have convergence with steady RSM.

I will be grateful if you agree to help me to conclude my work.

  Reply With Quote

Old   February 5, 2008, 14:03
Default Re: DPM in cyclone separator!!
  #2
Allan Walsh
Guest
 
Posts: n/a
For the first problem: I would not have Fluent generate the R-R distribution. I don't think the particle flow should have a big effect on the fluid flow, so your first job is to solve the fluid flow. Once you have that, set-up half-a-dozen particles of the size in the distribution you are intested in - each with a single diameter. Say 0.5, 1, 5, 10, 50 and 100 microns. Then for each particle size, find the separation efficiency and then look back at the distribution to find out what fraction of the particles have a certain diameter. For example, the 0.5 micron might represent 7% by mass of the distribution, the 1 micron 12% etc. This will give you the overall collection efficiency for that size distribution. Other variables will be important too, of course, like the coefficient of restitution, the step size for particle calculation, the initial particle velocity and position at the inlet,etc.

For the second problem: what do you mean by lack of convergence? Do you get different collection efficiencies as you run the simulation longer? Divergence? Pressure difference keeps changing? I don't have a lot of experience with cyclones, but for one project we worked on recently, we went with the hexagonal cell option in Fluent 6.3 and had pretty good luck with the steady RSM model (second order), but couldn't get good results with LES model.

Good luck.
arjun3020 likes this.
  Reply With Quote

Old   February 21, 2012, 05:17
Default
  #3
Member
 
arjun
Join Date: Oct 2011
Location: Tokyo, JAPAN
Posts: 66
Rep Power: 6
arjun3020 is on a distinguished road
Hi,
Allan Walsh.

I have particle details, e.g. 10 particles of range 1 to 10 micron. 50 particals of 20 micron and so on.
then how should i have to proceed to find out collection efficiency.?
please help me in detail..
arjun3020 is offline   Reply With Quote

Old   February 21, 2012, 06:08
Default
  #4
Senior Member
 
ghost82's Avatar
 
Daniele
Join Date: Oct 2010
Location: Italy
Posts: 992
Rep Power: 16
ghost82 will become famous soon enough
Inject your particles, then save or print to console escaped and trapped particles and mass flows and calculate from these data collection efficiencies.

Daniele
ghost82 is offline   Reply With Quote

Old   March 27, 2012, 04:57
Default
  #5
Member
 
arjun
Join Date: Oct 2011
Location: Tokyo, JAPAN
Posts: 66
Rep Power: 6
arjun3020 is on a distinguished road
Hi, you said inject single diameter particle is it mean single injection? or surface injections of uniform diameter distribution?
and what about flow rate of particle. if i inject particles of 20 (20% of total mass) micron then 30 micron (50% of total mass) and and 60 micron (30% of total mass).
then what about mass flow rate?
if my total mass flow rate is 0.01 kg/sec. then while running for first 20 micron particles what is mass flow rate i have to give to fluent. is it 0.01 kg/sec or 20 % of 0.01 kg/sec.?
please help.
arjun3020 is offline   Reply With Quote

Old   November 30, 2015, 05:14
Default
  #6
New Member
 
senthur rajasekar
Join Date: Nov 2014
Posts: 16
Rep Power: 3
senthur is on a distinguished road
yes, same problem im facing in cyclone separator.
i have to inject 10 different dia. size of particles in a single simulation.
at first, i will simulate each and every particle dia. with corresponding mass flow rate(x percentage from total mass flow rate). i will calculate the collection efficiency.

Now i calculated each and every particle dia. collection efficiency.

now i going to analyze by injecting all particles dia. by rosin rammler. it will ask for only total mass flow rate of the particles. How it will take( that this particle dia. is x mass flow rate) .(i.e. fluent is asking only total mass flow rate not individual particle mass flow rate.) How to specify individual mass flow rate in rosin rammler model.

And one more thing. how to post process the particle fate on the particular surface with particle dia. in that.
Kindly help me please. im facing for long time.
senthur is offline   Reply With Quote

Old   November 30, 2015, 05:23
Default
  #7
Senior Member
 
ghost82's Avatar
 
Daniele
Join Date: Oct 2010
Location: Italy
Posts: 992
Rep Power: 16
ghost82 will become famous soon enough
It's ok; you specify the total mass flow rate, because when you specify the Rosin Rammler distribution you are specifying for every particles diameter also its fraction, so you don't need to specify the flowrates for each injection.
__________________
Google is your friend and the same for the search button!
ghost82 is offline   Reply With Quote

Old   November 30, 2015, 12:09
Default
  #8
New Member
 
senthur rajasekar
Join Date: Nov 2014
Posts: 16
Rep Power: 3
senthur is on a distinguished road
okay.but how to post process the particle fate on the surface.
1. i need particle fate(escape, trap) on the surface along with particle diameter.
2. iam getting only total particle fate when i use summary not in particular surface( it is showing for full domain), how to get for particular surface.
3.And also how to find the particle fate for particular diameter on the surface.
Thanks for replying.
senthur is offline   Reply With Quote

Old   November 30, 2015, 12:45
Default
  #9
Senior Member
 
ghost82's Avatar
 
Daniele
Join Date: Oct 2010
Location: Italy
Posts: 992
Rep Power: 16
ghost82 will become famous soon enough
Try to activate "sample" at reports-->discrete phase-->sample.
Select the boundary(ies) and the release from injections.
Then click on start and go on with calculation.

In the working folder new .dpm files will be created.
Let us know if this solves your problem.
__________________
Google is your friend and the same for the search button!
ghost82 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
how to set BC of cyclone separator outlet Lcw FLUENT 5 February 22, 2012 02:40
DPM in CYCLONE SEPERATOR nagi FLUENT 6 March 6, 2011 20:59
problem about DPM of cyclone separator simulation jason FLUENT 4 November 12, 2007 04:15
DPM of cyclone fpingqian FLUENT 3 September 27, 2004 04:35
cyclone separator Vikky Main CFD Forum 1 June 29, 2003 06:05


All times are GMT -4. The time now is 06:38.