CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

mass flow inlet and pressure outlet with target mass flow rate

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By nsha

Reply
 
LinkBack Thread Tools Display Modes
Old   March 14, 2012, 11:12
Default mass flow inlet and pressure outlet with target mass flow rate
  #1
Senior Member
 
Join Date: May 2011
Location: Germany
Posts: 130
Rep Power: 5
Zigainer is on a distinguished road
Hi,

I have a question regarding the boundary condition.


I have a mass flow inlet and three pressure outlets. If assigned a specific target mass flow rate at each of these pressure outlets. But fluent does not always bring up the designated target mass flow rate.

At a first stage my problem is non-rotating. Almost every time I get the target mass flow rate (guess the difference is because the solution is not fully converged - solely increase mass flow rate at the inlet). But if I start to rotate (full mass flow rate at the inlet and increasing rotation speed) I get convergence problems and the target mass flow rate seems to be ignored..... so I asked myself if it would be better to use a pressure inlet and the mass flow will be reached because of the target mass flow rate ... or what would you suggest?


Thanks in advance!
Zigainer is offline   Reply With Quote

Old   March 15, 2012, 10:44
Default
  #2
Member
 
banty
Join Date: Mar 2012
Posts: 52
Rep Power: 4
banty is on a distinguished road
Quote:
Originally Posted by Zigainer View Post
Hi,

I have a question regarding the boundary condition.


I have a mass flow inlet and three pressure outlets. If assigned a specific target mass flow rate at each of these pressure outlets. But fluent does not always bring up the designated target mass flow rate.

At a first stage my problem is non-rotating. Almost every time I get the target mass flow rate (guess the difference is because the solution is not fully converged - solely increase mass flow rate at the inlet). But if I start to rotate (full mass flow rate at the inlet and increasing rotation speed) I get convergence problems and the target mass flow rate seems to be ignored..... so I asked myself if it would be better to use a pressure inlet and the mass flow will be reached because of the target mass flow rate ... or what would you suggest?


Thanks in advance!
Hi,


Actually it depends upon your problem or what u want to achieve.

Mass flow rate allow the total pressure to vary in response to the interior solution. on the other hand the pressure inlet BC, total pressure is fixed and the mass flux varies.
A mass flow inlet is used when it is more important to match a prescribed mass flow rate than to match the total pressure of the inflow stream.
banty is offline   Reply With Quote

Old   March 15, 2012, 10:56
Default
  #3
Senior Member
 
Join Date: May 2011
Location: Germany
Posts: 130
Rep Power: 5
Zigainer is on a distinguished road
Its actually more important to have the correct mass flow. I do simulation on leading edge impingment and therefore a mass flow results in a specific jet Re number, which is important for me.
I just switched off the traget mass flow rate at the pressure outlets and my solution is converged .... But I don't get the mass flow distribution (4 outlets) which I want (to compare my results to an exeriment) ... so I guess I have to adjust the gaug pressure for each pressure outlet until I get my mass flow rate.
Zigainer is offline   Reply With Quote

Old   March 15, 2012, 11:38
Default
  #4
Member
 
banty
Join Date: Mar 2012
Posts: 52
Rep Power: 4
banty is on a distinguished road
Quote:
Originally Posted by Zigainer View Post
Its actually more important to have the correct mass flow. I do simulation on leading edge impingment and therefore a mass flow results in a specific jet Re number, which is important for me.
I just switched off the traget mass flow rate at the pressure outlets and my solution is converged .... But I don't get the mass flow distribution (4 outlets) which I want (to compare my results to an exeriment) ... so I guess I have to adjust the gaug pressure for each pressure outlet until I get my mass flow rate.
yes, i think it will work. But if u are using Density based solver and want to compare the result with experiment data. then set direct pressure specification ( others methods are weak enforcement of avg. pressure(default setting) and strong enforcement of avg. pressure)for pressure calculation at outlet which is default with pressure based solver. this can can be done through TUI.
define>boundary condition>bc-setting no no
banty is offline   Reply With Quote

Old   March 15, 2012, 12:14
Default
  #5
Senior Member
 
Join Date: May 2011
Location: Germany
Posts: 130
Rep Power: 5
Zigainer is on a distinguished road
I am using pressure based solver ..... at the moment it works quite fine. I can use second order solver but if I increase the under relaxation factors to the default values I get divergence.... but I am happy do use 2nd order and no divergence. Probably I have to increase the under relaxation values more slowly
Zigainer is offline   Reply With Quote

Old   March 15, 2012, 14:10
Default
  #6
Member
 
banty
Join Date: Mar 2012
Posts: 52
Rep Power: 4
banty is on a distinguished road
For steady state solution, std process to run the simulation with 1st order for some iteration and wait for residuals to come down to certain level (~10^-2 to 10^-3) then switch on to 2nd order.
In transient case, care of the sub-iteration per time step..play with under relaxation factor.


Quote:
Originally Posted by Zigainer View Post
I am using pressure based solver ..... at the moment it works quite fine. I can use second order solver but if I increase the under relaxation factors to the default values I get divergence.... but I am happy do use 2nd order and no divergence. Probably I have to increase the under relaxation values more slowly
banty is offline   Reply With Quote

Old   March 15, 2012, 14:35
Default
  #7
Senior Member
 
Join Date: May 2011
Location: Germany
Posts: 130
Rep Power: 5
Zigainer is on a distinguished road
I do a steady state simulation and I am running 1st order first (otherwise I can't achieve convergence at all) with under relaxation factor of around 1/3 of the default values. Then I change to 2nd order which works fine, but when I start increasing the under relaxation factors my convergence behavior is really bad (around 1E-1 or divergence) .... but probably I should use more iterations for 2nd order and increase the under relaxation factors more sloley. But actually I can live with these low under relaxation factors. It would be more important to get some specific mass flow rates at the outlet and therefore I have to alter the gauge pressure at each outlet, because the “target mass flow rate” for pressure outlets results in divergence.
Zigainer is offline   Reply With Quote

Old   March 27, 2012, 17:28
Default
  #8
Senior Member
 
Join Date: Jul 2009
Posts: 207
Rep Power: 8
kingjewel1 is on a distinguished road
Quote:
Originally Posted by banty View Post
yes, i think it will work. But if u are using Density based solver and want to compare the result with experiment data. then set direct pressure specification ( others methods are weak enforcement of avg. pressure(default setting) and strong enforcement of avg. pressure)for pressure calculation at outlet which is default with pressure based solver. this can can be done through TUI.
define>boundary condition>bc-setting no no
I couldn't quite follow you, would you care to explain your reasoning behin strong and weak pressure enforcement?

A minor tweak:

define bound bc mass no
kingjewel1 is offline   Reply With Quote

Old   March 28, 2012, 13:26
Default
  #9
Member
 
banty
Join Date: Mar 2012
Posts: 52
Rep Power: 4
banty is on a distinguished road
here is the explanation
https://www.sharcnet.ca/Software/Fluent12/html/ug/node244.htm[/URL]
banty is offline   Reply With Quote

Old   September 24, 2012, 00:49
Default how to set flow rate at outlet
  #10
New Member
 
Noor
Join Date: Sep 2012
Posts: 2
Rep Power: 0
nsha is on a distinguished road
Hi, I have a problem to set the flow rate at the outlet boundary of my geometry. I'm simulation incompressible flow with known pressure at the inlet. I need to set my outlet to be at 0.9kg/s flow rate. What is the most suitable boundary condition should I use? Can I use 'mass flow-inlet' to input the flow rate value at the outlet? (since it is the only boundary condition option that ask for mass flow rate value) Or do I have to set the outlet to 'outflow'?
ELANCHEZIYAN likes this.
nsha is offline   Reply With Quote

Old   January 5, 2013, 21:51
Default
  #11
New Member
 
Join Date: Apr 2012
Posts: 20
Blog Entries: 3
Rep Power: 4
Guava Wang is on a distinguished road
hi zigainer,

about this questiong, what is your solution in the end? do you mind share your method with me? i have the same question with you, hope i can get some help from you. thank you.
Guava Wang is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Mass flow inlet and pressure outlet issue nikhil FLUENT 5 December 11, 2013 12:30
Compressible flow, no data at the outlet mireis FLUENT 1 July 28, 2010 05:22
mass flow in is not equal to mass flow out saii CFX 2 September 18, 2009 08:07
Target Mass Flow Rate Nitin FLUENT 6 March 12, 2004 05:39
what the result is negatif pressure at inlet chong chee nan FLUENT 0 December 29, 2001 05:13


All times are GMT -4. The time now is 03:12.