CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > FLUENT

Pressure boundary condition ANSYS Fluent

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 25, 2012, 12:27
Default Pressure boundary condition ANSYS Fluent
  #1
New Member
 
Jack
Join Date: Mar 2010
Posts: 28
Rep Power: 7
aggie is on a distinguished road
Dear all,

I want to simulate a high pressure vessel. Carbondioxide enters at 40 psi to the vessel and exits with some pressure loss which is not known. What I want to understand is the flow field inside the vessel and the pressure loss through the vessel so that I can estimate the exit pressure. However, when I want to use the pressure inlet-outlet boundary conditions, I am required to submit the exit pressure along with the inlet pressure. How would you handle this?

By the way, in Fluent material database there are two different CO2 as follows:
1- carbon dioxide (co2)
2= carbon dioxide- (co2-)

what does that - refer to?

THANKS.
aggie is offline   Reply With Quote

Old   March 26, 2012, 02:15
Default
  #2
Senior Member
 
Join Date: Mar 2009
Location: Indiana, US
Posts: 185
Rep Power: 8
delaneyluke is on a distinguished road
First of, CO2- is probably the carbonate ion, hence the properties do not include a density and Thermal cond. CO2 is the gaseous carbon dioxide.
Regards to your BC, if you do not know your outlet pressure you cannot specify a pressure outlet. You could do the following,
1. Extend your outlet to a region where the pressure is know and then specify the pressure outlet
2. Use the outflow BC, BUT this BC cannot be used along with a pressure inlet, you would have to specify a mass flow or velocity at the inlet.

Hope this helps
Regards
Luke
delaneyluke is offline   Reply With Quote

Old   March 26, 2012, 02:48
Default
  #3
New Member
 
Jack
Join Date: Mar 2010
Posts: 28
Rep Power: 7
aggie is on a distinguished road
1- I can not extend the region where the pressure outlet is known. It is not possible. The exit of the vessel will be the inlet of a compressor. The exit pressure is the main thing I want to see.
2- I know about the outflow condition, but as you said it can not be used along with pressure inlet condition.

For carbon dioxide, what you said makes sense. Given the flow conditions, the carbon dioxide will be compressible and will possibly not an ideal gas. So, what would you offer in order to take compressiblity effect into account? which kind of density method should be used?

THANKS.
aggie is offline   Reply With Quote

Old   April 19, 2012, 01:40
Default
  #4
New Member
 
Join Date: Apr 2012
Posts: 20
Blog Entries: 3
Rep Power: 5
Guava Wang is on a distinguished road
If you want to know the pressure loss in the vessel, you can set BC like this:
velocity inlet /mass flow, pressure outlet.

Hope this helps.

Reds.
Guava
Guava Wang is offline   Reply With Quote

Old   April 20, 2012, 18:02
Default
  #5
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 675
Rep Power: 13
LuckyTran will become famous soon enough
Quote:
Originally Posted by Guava Wang View Post
If you want to know the pressure loss in the vessel, you can set BC like this:
velocity inlet /mass flow, pressure outlet.

Hope this helps.

Reds.
Guava
This won't work well for a compressible flow.

Quote:
Originally Posted by aggie View Post
1- I can not extend the region where the pressure outlet is known. It is not possible. The exit of the vessel will be the inlet of a compressor. The exit pressure is the main thing I want to see.
2- I know about the outflow condition, but as you said it can not be used along with pressure inlet condition.

For carbon dioxide, what you said makes sense. Given the flow conditions, the carbon dioxide will be compressible and will possibly not an ideal gas. So, what would you offer in order to take compressiblity effect into account? which kind of density method should be used?

THANKS.
The best thing to do is use a pressure inlet. It is the most physically meaningful, and it is what you are interested in.

You can use a pressure outlet, and activate the target mass flow rate option. It will iterate the pressure at the outlet to achieve the mass flow rate that you specified. This is exactly what you are trying to solve for is this outlet pressure. But you need to know the mass flow rate. I believe you should already know the mass flow rate, as you do not have a fully defined problem without it (you just probably just forgot to mention it).

You do not need to and should not extend your domain, that suggestion does not make any sense, so do not do that.

Properties should not be a problem. It is doable at some point. However, I would worry about this last. You can use real gas models (which do account for compressibility effects). If that is not sufficient, you can specify polynomial relations for each property. If that is not enough, you can use a UDF to specify arbitrary properties. Don't forget the additional computational cost with having to calculate the properties, they may become significant depending on your problem.

Hope that helps,

Last edited by LuckyTran; April 25, 2012 at 01:38.
LuckyTran is online now   Reply With Quote

Old   April 24, 2012, 22:43
Default
  #6
New Member
 
Join Date: Apr 2012
Posts: 20
Blog Entries: 3
Rep Power: 5
Guava Wang is on a distinguished road
Hi LuckyTran

[QUOTE=LuckyTran;355915]This won't work well for a compressible flow.

As described, the flow in calculation region is imcompressible, but not a compressible flow.

The unconsidering region is a compressible, so the extension outlet can't be made to simple the case. The information shows as below,
"The exit of the vessel will be the inlet of a compressor"
Guava Wang is offline   Reply With Quote

Old   April 25, 2012, 01:39
Default
  #7
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 675
Rep Power: 13
LuckyTran will become famous soon enough
[QUOTE=Guava Wang;356776]Hi LuckyTran

Quote:
Originally Posted by LuckyTran View Post
This won't work well for a compressible flow.

As described, the flow in calculation region is imcompressible, but not a compressible flow.

The unconsidering region is a compressible, so the extension outlet can't be made to simple the case. The information shows as below,
"The exit of the vessel will be the inlet of a compressor"
Your point? It's still not meaningful to apply a velocity boundary condition when it should be a pressure boundary condition.
LuckyTran is online now   Reply With Quote

Reply

Tags
carbon dioxide, co2, pressure inlet, pressure outlet, vessel

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
asking for Boundary condition in FLUENT Destry FLUENT 0 July 27, 2010 00:55
Pressure Boundary condition abishek FLUENT 1 July 28, 2008 08:14
Boundary condition in pressure equation Paolo Lampitella FLUENT 0 February 21, 2008 07:30
what the result is negatif pressure at inlet chong chee nan FLUENT 0 December 29, 2001 06:13
Pressure Boundary Condition chiseung FLUENT 1 June 19, 2001 21:05


All times are GMT -4. The time now is 01:23.