CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

Compressible solver for low Mach

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   January 26, 2013, 04:45
Default Compressible solver for low Mach
  #1
New Member
 
Lipo Wang
Join Date: Dec 2012
Posts: 14
Rep Power: 4
nickna is on a distinguished road
Dear all,
If anybody has the experience in using the compressible solver for very low Mach (thus almost incompressible) cases? Is it possible?
If yes, in principle the calculation can be much speeded up because we dont not need to solve the Poission eq for pressure.
If no, where is the main problem?

Many thanks for your suggestion!
nickna is offline   Reply With Quote

Old   January 26, 2013, 06:32
Default
  #2
Senior Member
 
Filippo Maria Denaro
Join Date: Jul 2010
Posts: 1,587
Rep Power: 20
FMDenaro will become famous soon enough
Quote:
Originally Posted by nickna View Post
Dear all,
If anybody has the experience in using the compressible solver for very low Mach (thus almost incompressible) cases? Is it possible?
If yes, in principle the calculation can be much speeded up because we dont not need to solve the Poission eq for pressure.
If no, where is the main problem?

Many thanks for your suggestion!
Hi,
generally, the low-Mach solver is quite different from the standard compressible solver due to the stiff problem (high velocity magnitude of sound waves compared to convective waves).
The method to get a well-conditioned problem often introduces an expansion arounf the M=0 state and consequently an elliptic equation. You can see many textbook, e.g. http://books.google.it/books/about/C...4C&redir_esc=y
FMDenaro is offline   Reply With Quote

Old   January 26, 2013, 07:16
Default
  #3
Senior Member
 
cfdnewbie
Join Date: Mar 2010
Posts: 551
Rep Power: 11
cfdnewbie is on a distinguished road
But in general, yes, it is possible to use a compressible solver in a low Mach number setting, but the timestep will become very small (or the accuracy very low)...
cfdnewbie is offline   Reply With Quote

Old   January 26, 2013, 07:37
Default
  #4
Senior Member
 
Filippo Maria Denaro
Join Date: Jul 2010
Posts: 1,587
Rep Power: 20
FMDenaro will become famous soon enough
Quote:
Originally Posted by cfdnewbie View Post
But in general, yes, it is possible to use a compressible solver in a low Mach number setting, but the timestep will become very small (or the accuracy very low)...
I agree, even small perturbations in the numerical solution of the density equation will be amplified in the pressure ... I had experience that the Mach number to work on should be not lesser than 0.1 - 0.05 ...
FMDenaro is offline   Reply With Quote

Old   January 26, 2013, 22:40
Default
  #5
Senior Member
 
Martin Hegedus
Join Date: Feb 2011
Posts: 497
Rep Power: 9
Martin Hegedus is on a distinguished road
Yes, it is possible with Mach number preconditioning. But, you lose time accuracy.
Martin Hegedus is offline   Reply With Quote

Old   January 27, 2013, 05:23
Default
  #6
Super Moderator
 
praveen's Avatar
 
Praveen. C
Join Date: Mar 2009
Location: Bangalore
Posts: 244
Blog Entries: 6
Rep Power: 9
praveen is on a distinguished road
There is a preconditioned Roe scheme in which the dissipation is modified to yield correct scheme in the low mach limit. There is also an AUSM version which performs well in low mach limit but I dont recall its precise name now. These are all consistent flux functions which lead to time accurate schemes. However they require very small time step for stability and implicit schemes are necessary. E.g., SU2 code has a preconditioned Roe scheme.

See for example

http://www.sciencedirect.com/science...45793003000781

which has a very nice asymptotic analysis of upwind schemes in low mach limit.

In the following paper, they show that above preconditioned scheme if used in explicit version requires time step of order mach^2 which is too restrictive and hence an implicit scheme is needed for efficiency

http://link.springer.com/article/10....0009-0?LI=true

A different approach is advocated in this paper

http://www.sciencedirect.com/science...21999108000429

where the reconstruction process is modified to get well behaved schemes in low mach limit. A similar approach is given here

http://elib.dlr.de/76675/1/ICCFD7-2204_paper.pdf
__________________
http://twitter.com/cfdlab
praveen is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Creating New Solver: For particle-laden compressible jets sankarv OpenFOAM Running, Solving & CFD 17 December 3, 2014 20:41
Creating New Solver: For particle-laden compressible jets sankarv OpenFOAM 0 April 4, 2010 18:06
Can 'shock waves' occur in viscous fluid flows? diaw Main CFD Forum 105 November 20, 2009 05:19
non-dimensional analysis in Fluent Endee FLUENT 8 September 7, 2005 16:16
Compressible Flow Modelling? yeo FLUENT 4 March 7, 2003 08:08


All times are GMT -4. The time now is 19:52.