CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

Can't get good results on ahmed body research

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   September 10, 2008, 04:48
Default Can't get good results on ahmed body research
  #1
Michael
Guest
 
Posts: n/a
Hello,

I already found a lot of hints in this forum, but for my problem i don't know exactly what my problem can be.

For my studies I have to do a research on the ahmed body with 20 degrees on the back end. This Body should have a drag coefficient from about 0.25 but my calculations have 0.45 " 0.5 as result. The position and the magnitude from the eddies in my solution seems to be right. The max Kinetic Turbulence Energy is in the lower eddy on the back, like in the paper i found. I am confused that my solution is twice as big as it should be.

Maybe someone sees a big mistake in my settings or can give me a hint how I can find the problem.

I already tried different mesh sizes and refinements, but it hasn't changed something. I am using Tetra Meshing with Prism layers on the body. The Element size on the Body is 10 mm, with 5 prism layers with ratio 1.2 and first height of 2 mm. My last mesh had approx. 800000 Elements. But with other meshes i already had 2*10^6 Elements, the change was verry small.

My Boundaries are:

- Velocity Inlet with 40 m/s, the rest is standard settings

- Pressure outlet with gauge pressure 0 pa

- Symmetry

- Ground is wall with defined shear stress 0

- Walls are symmetry

Models are:

- Solver: pressure based and green gauss node based, rest is standard settings - Viscous: ke; realizable; non equilibrium wall function,

Solution controls are:

150 iterations standard settings (first order) then second order and coupled for pressure velocity coupling with standard parameters.

I checked my reference settings and scaled the mesh and for the drag coefficient I used the force in x direction.

With best regards,

Michael

  Reply With Quote

Old   September 10, 2008, 10:24
Default Re: Can't get good results on ahmed body research
  #2
BastiL
Guest
 
Posts: n/a
Did you use the correct reference area?
  Reply With Quote

Old   September 10, 2008, 10:56
Default Re: Can't get good results on ahmed body research
  #3
Michael
Guest
 
Posts: n/a
I used the Projected Areas function in x direction. I get 0.056 m which is the half of the entire area (0.112m).

If i calculate with symmetrie, the Forces are only for the half body, aren't they? The velocity is also right. Density is 1.225 kg/m and viscosity 1.78e-5.

As result i get 27 N pressure force and 2 N viscous Force on the half body at 40 m/s air speed.

  Reply With Quote

Old   September 10, 2008, 14:38
Default Re: Can't get good results on ahmed body research
  #4
paulh
Guest
 
Posts: n/a
How are you specifying turbulence at the inlet? How big is your 'tunnel', i.e. what is your blockage factor? What is predicted average pressure at the inlet? What is predicted max Cp at stagnation?
  Reply With Quote

Old   September 10, 2008, 18:10
Default Re: Can't get good results on ahmed body research
  #5
michael
Guest
 
Posts: n/a
Inlet turbulence:

- turbulent intensity 2% - turbulent lenght scale 0.1 m

tunnel: 3m in front an 5m behind the body = 10 m. 2.5m high and 2.5m large, that gige a blockage factor of 0.9%

an absolute pressure plot at the inlet shows 1.013e^10 pa on the entire inlet (small place has an higher pressure, approx 0.5 pa).

i am not sure if i understood the thing with the cp right. a force report give a cp of 0.47.

best regards
  Reply With Quote

Old   September 11, 2008, 01:36
Default Re: Can't get good results on ahmed body research
  #6
michael
Guest
 
Posts: n/a
i plotet a cp contour on the body. the cp at the nose was 1, the cp at the fillet on the upper and down side of the nose was -2.5. i also found a paper with some pictures of results. Pressure plot on the symmetry, pathlines at the back are pretty close. the turbulent kinetic energy plots at 4 cuts behind the body are a bit different, but the guy used a different viscos modell. the biggest difference was 1.5 m behind the body
  Reply With Quote

Old   September 11, 2008, 04:35
Default Re: Can't get good results on ahmed body research
  #7
michael
Guest
 
Posts: n/a
i found a big problem in the modell of the body. the two vertical fillets on the front where missing.

Now i have a cd of 0.32 and i am searching the next 20%.

sorry for this needles posts.

best regards

  Reply With Quote

Old   September 11, 2008, 13:29
Default Re: Can't get good results on ahmed body research
  #8
Paulh
Guest
 
Posts: n/a
In the CD-adapco products, both STAR-CD and STAR-CCM+, I set the ratio of turbulent viscosity to laminar viscosity at the inlet to be something on the order of 1 to 10. Too much more and your fluid starts acting like molasses. See if you can come up with a scalar plot of the ratio at the centerplane. It should be your inlet value till somewhere close to the vehicle. External aerodynamic analyses can be pretty sensitive to initial and inlet turbulence values.
  Reply With Quote

Old   September 17, 2008, 13:55
Default Re: Can't get good results on ahmed body research
  #9
Andy R
Guest
 
Posts: n/a
Micheal Ditto what Paul said.

You want a viscosity ratio less than on. Lockheeds low speed tunnel (which is pretty typical) has a viscosity ratio of 0.3 (in fact that might be 0.03) Ie the turbulent viscosity is less (perhaps much less ) than the molecular viscosity.

I learned this one the hard way. Go back to the source paper and see if there is any estimate of tunnel conditions. The turbulent intensity should be very low 1% or less and the length scale in a tunnel is the lenght scale of what ever the smallest feature of the flow straighteners (screens)

Good Luck

Andy R
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[GAMBIT] Ahmed Body 3D mesh Saima ANSYS Meshing & Geometry 14 July 16, 2013 10:16
Ahmed Body on 25degree dimsum STAR-CCM+ 3 August 18, 2011 06:35
Drag over Ahmed body Shamoon Jamshed FLUENT 2 May 18, 2009 14:15
Flow around the ahmed body (large eddy simulation) Benzamia CFX 0 February 26, 2007 06:03
Ahmed Body Chris Robinson Main CFD Forum 2 December 6, 1999 17:38


All times are GMT -4. The time now is 08:35.