
[Sponsors] 
May 4, 2001, 02:48 
Volume fraction cal. in SIMPLE

#1 
Guest
Posts: n/a

from VOF beginner
I want to know the method about calculations of volume fraction in SIMPLE method. SIMPLE is a implicit method. Do I have to make implicit form of void fraction equation ? Can I use explicit method ? if it possible, which one is better ? and I have another question. In brokendam problem, how can I satisfy profit boundary condition (especially pressure...) ? kind regards. 

May 4, 2001, 04:42 
Re: Volume fraction cal. in SIMPLE

#2 
Guest
Posts: n/a

Dear "VOF beginner"
There is no relationship between VOF and SIMPLE; which is not an implicit method, but Semi Implicit Method for Pressure Linked Equations. SIMPLE is a iterative general method to derive pressure equation from NS and continuity eqs. for imcompressible fluids (almost any book of FM have an explanation of it). Now a days there is a "family" of SIMPLE like methods for this problem (SIMPLEST, SIMPLEC, SIMPLER). VOF is a general method to track interfaces in FV for two phases incompressible fluids. It uses a scalar marker transport eq. to represent the region occupied by each phase (say liquid with scalar=1, gasesous with scalar=0). If you use VOF, you will update every time step in every cell the values of each fluid properties and to move the interface you need the velocity field, so the resolution of interface dynamic is linked to solution of fluid field, and viceversa. In VOF you should move the interface from cell to cell, and therefore, you should use explicit schemes to track the interface through the domain. You must to preserve the CFL criterium to avoid interface displacement greater than a cell length, and it will forces you to calculate velocity in an explicit way. I had used SIMPLEST for pressure calculation in conjunction with explicit Yanenko's Fractional Step Method and PLIC (Picewice Linear Interface Contruction  VOF family) method to tracking the interface. It works and I had very nice agreement with experiments in liquid sheet atomization and droplets formation. Regards VOF user 

May 4, 2001, 09:22 
Re: Volume fraction cal. in SIMPLE

#3 
Guest
Posts: n/a

Hi, Kike,
I am interested in using PLICVOF (in 3D). Could you please post some references that describe the details how to implement PLIC in 3D? How is curvature calculated? Do you know of any site that I can get a source code? Thanks! pyhsieh 

May 4, 2001, 11:39 
Re: Volume fraction cal. in SIMPLE

#4 
Guest
Posts: n/a

Hi kike Is it possible to apply the VOF in the absence of velocity fields? I need to calculate a shape of a drop in static conditions and I wonder if I can use VOF methodology.
Thanks 

May 4, 2001, 11:55 
Re: Volume fraction cal. in SIMPLE

#5 
Guest
Posts: n/a

If you want to use an SIMPLE method then you will have to set time critieria for it since
1) VOF is solved explicitly 2) time limits with surface tension 3) Viscous time limits So to answer your question I think explicit is the way to go. 

May 4, 2001, 12:05 
Re: Volume fraction cal. in SIMPLE

#6 
Guest
Posts: n/a

Yes it is possible to apply VOF in absence of a velocity field. A situation which comes to mind is the simulation of a spherical drop in a gravity free environment (Brackbill,1992). This situation illistrates the most problematic source you will have in your research. Surface Tension. If you are doing a problem in which surface tension is important...
Then don't use VOF use either a LevelSet method or a surface tracking method. These methods can estimate your curvature much better!!!!!!!!!!!!! Some advances have been made with the surface tension in regards to "spurious currents" but not enough... 

May 4, 2001, 12:35 
Re: Volume fraction cal. in SIMPLE

#7 
Guest
Posts: n/a

Thanks for your answer Bubba, Its very instructive. I would like to ask you about some references on the methods you propose, because for me the curvature prediction is important. Also if you know some codes who implement them.
Thanks Arturo 

May 4, 2001, 14:55 
Re: Volume fraction cal. in SIMPLE

#8 
Guest
Posts: n/a

Tryggvason (old homepage) Interface Tracking 
http://wwwpersonal.engin.umich.edu/~gretar/ Zaleski (I see Kike with the same email extension)  Look at Popinet's thesis. http://www.lmm.jussieu.fr/~zaleski/zaleski.html Level Set.... Look through list of reports  http://www.math.ucla.edu/applied/cam/index.html I personally would not recommend a commercial code for applications with airwater (significant surface tension force) since they typically use CSF with SOLAVOF. However I have seen a publication recently from someone using the Parallel version of CFX simulating rising bubbles, so it may have been improved. check here under "computer simulations of multi phase flows." http://ctcr4.chem.uva.nl/jasper/ 

May 10, 2001, 05:43 
Re: Volume fraction cal. in SIMPLE

#9 
Guest
Posts: n/a

Dear N
I am sorry to ansuwer you so late. Yes, it is formally possible, but useless from my point of view. VOF method is specially usefull to track moving and quite distorted interfaces with fracture and reconnection. If it is not your case you can use, as Bubba say, a surface tracking method. If you consider surface tension and you apply the CFS method (Brackbil) or the method employed by SURFER (Zaleski), both based on VOF scalar field, then you should add a new term into the momentum eq. and you will have "parasite currents" ie. a small magnitude velocity field, and its related problems. I think the references Bubba had gave you are good enough to choose a way to start. I specially recomend you to read the content of the PhD Thesis of my colleagues S. Popinet (for surface markers method) and D. Gueyffier (3D VOF). Best regards Kike 

May 10, 2001, 05:58 
Re: Volume fraction cal. in SIMPLE

#10 
Guest
Posts: n/a

Dear pyhsieh
I am sorry to ansuwer you so late. I don't know any published reference for PLIC in 3D, but you can read the PhD. dissertation of my colleague D. Gueyffier from Prof. Zaleski web page: http://www.lmm.jussieu.fr/~zaleski/interface_pubs.html It is specially dedicated to VOFPLIC and Surface Tension in 3D. You can also get the email address of Prof. Zaleski from this page and get in contact with him to talk about the source code (he is the head researcher of our group and author of SURFER). Best whishes Kike 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
BlockMesh FOAM warning  gaottino  OpenFOAM Native Meshers: blockMesh  7  July 19, 2010 14:11 
interDyMFoam  change in volume fraction  gopala  OpenFOAM Running, Solving & CFD  0  April 27, 2009 10:46 
fluent add additional zones for the mesh file  SSL  FLUENT  2  January 26, 2008 12:55 
the Eulerian model and the lower volume fraction  hx li  FLUENT  2  October 27, 2005 06:17 
Volume Fraction  cheong  FLUENT  1  November 28, 2001 05:06 