CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

need help on 3D meshing of flat-back airfoil

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 13, 2009, 00:08
Default need help on 3D meshing of flat-back airfoil
  #1
LSC
Member
 
LSC
Join Date: May 2009
Posts: 58
Rep Power: 8
LSC is on a distinguished road
The airfoil profile that I am meshing does not end with a common vertex at the trailing edge. It has a equal finite thickness for both upper and lower surface. I have followed the tutorials from Cornell. At the trailing edge, I have 3 vertex with 2 being the end points at the trailing edge and 1 at the center(y=0). My problem is with the 2 separate edges connecting the domain and the edge on the trailing edges. I tried using grid spacing with y+ =1 but encountered problems running the solver..I am actually doing 2D analysis but CFX only solves 3D..How to tackle the region?
LSC is offline   Reply With Quote

Old   May 16, 2009, 09:05
Default
  #2
Senior Member
 
John Chawner
Join Date: Mar 2009
Location: Fort Worth, Texas, USA
Posts: 223
Rep Power: 9
jchawner is on a distinguished road
It seems to me that you need more than 3 points on the blunt trailing edge. By using only 3 points you have a huge spacing jump across the wake region thru the boundary layer mesh into the blunt-wake mesh.

My suggestion for the blunt trailing edge is to cluster points to the top and bottom using the same spacing as to the airfoil surface and put enough points on the TE to have a smooth variation in cell sizes.

Hope this helps.
__________________
John Chawner / jrc@pointwise.com / www.pointwise.com
Blog: http://blog.pointwise.com/
on Twitter: @jchawner
jchawner is offline   Reply With Quote

Old   May 16, 2009, 09:10
Smile
  #3
LSC
Member
 
LSC
Join Date: May 2009
Posts: 58
Rep Power: 8
LSC is on a distinguished road
Thanks a lot for the suggestion..will try it out
LSC is offline   Reply With Quote

Old   May 18, 2009, 05:27
Default
  #4
Member
 
Anton Lyaskin
Join Date: Mar 2009
Location: Samara, Russia
Posts: 66
Rep Power: 8
A_Lyaskin is on a distinguished road
And why do you aim for y+=1 at the trailing edge? This gives you a huge spacing jump also in the flow direction. IMHO it's better to take the length of the first cell in the wake equal to the length of the last cell at the surface
A_Lyaskin is offline   Reply With Quote

Old   May 18, 2009, 05:40
Default
  #5
LSC
Member
 
LSC
Join Date: May 2009
Posts: 58
Rep Power: 8
LSC is on a distinguished road
I am trying to investigate whether a grid spacing corresponding to Y+=1 would give me more accurate results for Lift and Drag Coefficient.. The blunt trailing edge certainly posed a lot of problems and I am trying very hard to figure how to mesh the wake region..What I tried was to put more nodes in the wake region which grid spacing equal to the surface node which increasing grid size towards the centerline..not sure whether this is the best approach..kindly advice
LSC is offline   Reply With Quote

Old   May 18, 2009, 06:26
Default
  #6
Member
 
Anton Lyaskin
Join Date: Mar 2009
Location: Samara, Russia
Posts: 66
Rep Power: 8
A_Lyaskin is on a distinguished road
Well, y+ at the trailing edge itself wouldn't have much influence at the results. However you'll probably see some difference for y+=1 and y+, say, 100, but just because of numerical error caused by spacing jump.

Actually from my experience I've found another tricky thing - if you have a "stripe" of fine mesh in wake, its alignment also influence the results (CL). That's because flow leaves the trailing edge more or less in the direction of airfoil midline and then it takes some distance to turn back to flow direction. This in turn means that somewhere close to the airfoil you have spacing jump in the flow direction again! To minimize the effect you have to align the mesh with the wake - make a run, find the zero streamline, align the block edges with it, probably make a couple of more iterations, and than repeat the process for the other angle of attack...
A_Lyaskin is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Airfoil Meshing Scheme in Gambit J. Weiler FLUENT 6 October 2, 2011 15:41
Meshing airfoil Wason FLUENT 6 November 8, 2009 12:50
meshing over a flat plate bhanu kishan Main CFD Forum 1 February 7, 2009 15:45
help! meshing on airfoil naca0015 using cosmosflo TTS Main CFD Forum 0 March 4, 2008 04:57
Meshing An airfoil with a simple plain flap S. Kalam FLUENT 7 January 30, 2005 21:22


All times are GMT -4. The time now is 02:45.