CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

how to print the results from CFX-4.2

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   June 15, 1999, 20:37
Default how to print the results from CFX-4.2
  #1
cfd_99
Guest
 
Posts: n/a
Who knows how to print the results from CFX-4.2. Thanks
  Reply With Quote

Old   June 17, 1999, 06:56
Default Re: how to print the results from CFX-4.2
  #2
james date
Guest
 
Posts: n/a
Hi, look at the bottom of this command file >>OUTPUT OPTIONS
>>PRINT OPTIONS >>WHAT pick what you want when you want it. Read Chapter 9. in the user guide (~page 159 in 1995 guide) that should tell you all you need to know. Good luck with CFX - you'll need it !! Regards James Date

>>CFX4
>>OPTIONS

THREE DIMENSIONS

BODY FITTED GRID

CARTESIAN COORDINATES

TURBULENT FLOW

ISOTHERMAL FLOW

INCOMPRESSIBLE FLOW

STEADY STATE
>>MODEL DATA
>>DIFFERENCING SCHEME

U VELOCITY 'UPWIND'

V VELOCITY 'UPWIND'

K 'UPWIND'

EPSILON 'UPWIND'
>>TITLE

PROBLEM TITLE 'BOUNDARY CONDITION STUDY'
>>PHYSICAL PROPERTIES

>>STANDARD FLUID

FLUID 'WATER'

STANDARD FLUID REFERENCE TEMPERATURE 2.7300E+02

>>TURBULENCE PARAMETERS

>>TURBULENCE MODEL

TURBULENCE MODEL 'K-EPSILON'
>>SOLVER DATA
>>PROGRAM CONTROL

MAXIMUM NUMBER OF ITERATIONS 1000

MAXIMUM CPU TIME 14400

OUTPUT MONITOR POSITION 5.000000E-01 5.000000E-01 5.000000E-01

MASS SOURCE TOLERANCE 1.0000E-06
>>EQUATION SOLVERS

U VELOCITY 'AMG'

V VELOCITY 'AMG'

PRESSURE 'AMG'

K 'AMG'

EPSILON 'AMG'
>>PRESSURE CORRECTION

PISO
>>UNDER RELAXATION FACTORS

U VELOCITY 7.5000E-01

V VELOCITY 7.5000E-01

PRESSURE 1.0000E+00

VISCOSITY 1.0000E+00

K 7.5000E-01

EPSILON 7.5000E-01
>>CREATE GRID
>>INPUT GRID

READ GRID FILE

FORMATTED
>>MODEL BOUNDARY CONDITIONS
>>PRESSURE BOUNDARIES

PATCH NAME 'FACE-NUMBER-0'

PRESSURE 0.0000E+00
>>PRESSURE BOUNDARIES

PATCH NAME 'FACE-NUMBER-36'

PRESSURE 0.0000E+00
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-3'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-8'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-13'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-18'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-23'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-28'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-33'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>SET VARIABLES

PATCH NAME 'FACE-NUMBER-37'

U VELOCITY 1.0000E+00

PRESSURE 0.0000E+00

K 1.0000E-03

EPSILON 1.0000E-03
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-6'
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-11'
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-16'
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-21'
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-26'
>>WALL BOUNDARY CONDITIONS

PATCH NAME 'FACE-NUMBER-31'
>>OUTPUT OPTIONS
>>PRINT OPTIONS

>>WHAT

U VELOCITY

V VELOCITY

W VELOCITY

PRESSURE

DENSITY

VISCOSITY

K

EPSILON

WALL PRINTING

>>WHERE

K PLANES 1

ALL BLOCKS

>>WHEN

INITIAL GUESS

FINAL SOLUTION

EACH TIME STEP

EACH ITERATION
>>STOP
  Reply With Quote

Old   June 20, 1999, 08:54
Default Re: how to print the results from CFX-4.2
  #3
David Creech
Guest
 
Posts: n/a
Hello,

CFX produces a dump file with the results which can be viewed using graphical tools such as View and Visualize. If you want to extract results from the solution and output them to a text file, you can use the USRPRT subroutine.

This subroutine allows you to print out any variable at any time in the solution and at any place in the domain. I have used this to extract data along specific lines in the domain and use the data as the input for other simulations. It is the only way to automate post-processing.

I have posted a sample fortran file using this subroutine at:

http://bgtibm1.me.uiuc.edu/people/d-...lot/index.html

Please read the explanation of this subroutine; I just got it to the point where it did what I needed, and there are a few problems with it. It could be a VERY useful utility with some more work.

David Creech CFD Literature Catalog CFD Subroutine Archive
  Reply With Quote

Old   June 20, 1999, 09:44
Default Re: how to print the results from CFX-4.2
  #4
John C. Chien
Guest
 
Posts: n/a
(1). I am surprised that one is still interested in printing out the results file. Back in early 70's, I used to get one big box of printout for every 3-D Navier-Stokes run. Since then, I have decided to save nature resources by using graphic post-processing. (2). For a 3-D case with a 250,000 mesh points, there will be 10 essential variables per mesh point ( x,y,z,u,v,w,p,t,rho,mu ). This is a minimum list, the total number of variables is 250,000 x 10 = 2,500,000. If we print 10 numbers per line, we have 250,000 lines of output. If one can print 80 lines per page using small font size, then we will have 250,000/80 = 3125 pages. This is equivalent to 4 thick books, each with 800 pages. (3). It is a good idea to do internal processing and save only needed results first, without printing or even file saving at all. ( I am constantly running out of disk space. And the solution is vey simple, just delete the files. ) (4). How long would it take to read 4 thick books of computed results? ( I had plotted 3-D results from printout to get velocity vector field plots with arrow heads included, once a long time ago. )
  Reply With Quote

Old   June 20, 1999, 23:32
Default Re: how to print the results from CFX-4.2
  #5
David Creech
Guest
 
Posts: n/a
I have never found a need to print out the entire solution. What I have found very useful is the ability to print out single lines or planes of data. I do this in cases where I am interested in comparing line plots of some variable for large parametric studies. This is much faster than starting up a postprocessor, defining a line, and outputing the results to a file.

Another reason that I do this is when I am taking the output of a cfd solution (such as the heat flux at a wall) and use this as the input of another simulation (such as a custom code to predict steel shell solidification).
  Reply With Quote

Old   June 21, 1999, 09:23
Default Re: how to print the results from CFX-4.2
  #6
John C. Chien
Guest
 
Posts: n/a
(1). Yes, I think the interface between codes is the place where interaction is always required. (2). And the graphic post-processing or inline-processing is essential to the future of CFD.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Comparison of fluent and CFX for turbomachinery Far CFX 52 December 26, 2014 19:11
Vectorial animation of results in CFX attilio CFX 2 February 24, 2009 19:46
time averaged results as initial conditions in CFX mike CFX 8 May 7, 2007 14:54
Import results to CFX post MatjazR CFX 1 October 17, 2005 09:07
CFX 4.2 Zoltan Turzo Main CFD Forum 4 March 11, 1999 18:31


All times are GMT -4. The time now is 16:16.