CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Main CFD Forum

NACA 0012 lift and drag coefficient.

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 28, 2012, 20:32
Default NACA 0012 lift and drag coefficient.
  #1
New Member
 
Tan
Join Date: Dec 2011
Posts: 10
Rep Power: 5
Tom Lucius is on a distinguished road
I am running ANSYS fluent simulation flow over naca 0012 airfoil.
So far the lift coefficient is similar with the published papers.
The problem is drag coefficient is different so much in term of value compared to published papers.
I have check my mesh quality and boundary condition, it shows no problem.
Any idea why drag coefficient is different ???
Tom Lucius is offline   Reply With Quote

Old   March 28, 2012, 21:18
Default
  #2
New Member
 
Minjae Lee
Join Date: Mar 2012
Location: South Korea
Posts: 3
Rep Power: 5
leemj is on a distinguished road
you may check the tubulrence model. which turbulence model did you appplied? generally, S-A 1equation model predict the drag coefficient less than compare with published paper. I recommand to you T-SST 4equation turbulence model.

if you solving 2 dimensional problem using about 300 surface nodes on the airfoil, that the drag coefficient is predicted less than 5% error.
leemj is offline   Reply With Quote

Old   March 28, 2012, 22:33
Default
  #3
New Member
 
Tan
Join Date: Dec 2011
Posts: 10
Rep Power: 5
Tom Lucius is on a distinguished road
Quote:
Originally Posted by leemj View Post
you may check the tubulrence model. which turbulence model did you appplied? generally, S-A 1equation model predict the drag coefficient less than compare with published paper. I recommand to you T-SST 4equation turbulence model.

if you solving 2 dimensional problem using about 300 surface nodes on the airfoil, that the drag coefficient is predicted less than 5% error.
Reynolds number = 360,000
Is it laminar or turbulence flow??
Tom Lucius is offline   Reply With Quote

Old   March 29, 2012, 03:32
Default
  #4
New Member
 
Minjae Lee
Join Date: Mar 2012
Location: South Korea
Posts: 3
Rep Power: 5
leemj is on a distinguished road
Quote:
Originally Posted by Tom Lucius View Post
Reynolds number = 360,000
Is it laminar or turbulence flow??
The flow is fully turbulent flow when Re>2,300 in pipe flow for air. So I recommand to you that you need to apply the turbulence model especially transition-SST 4equation model. In addition, not only you have to making surface nodes more than 270 but also consider wall y plus.
(you can find the wall y plus information NASA hompage.)
leemj is offline   Reply With Quote

Old   March 29, 2012, 05:32
Default
  #5
Senior Member
 
truffaldino's Avatar
 
Join Date: Jan 2011
Posts: 234
Blog Entries: 5
Rep Power: 8
truffaldino is on a distinguished road
Quote:
Originally Posted by Tom Lucius View Post
Reynolds number = 360,000
Is it laminar or turbulence flow??
At this reynolds number the flow is transitional. E.g. at zero angle of attack transition to turbulent at this Re and this airfoil happens at about 80-90% of the wing chord. At angle attack 5deg it happens at about 25% of wing chord.

Using turbulence models in CFD-software without special user input will likely give very wrong results for drag at such reynolds number.

Truffaldino
truffaldino is offline   Reply With Quote

Old   March 29, 2012, 05:54
Default
  #6
New Member
 
Tan
Join Date: Dec 2011
Posts: 10
Rep Power: 5
Tom Lucius is on a distinguished road
Quote:
Originally Posted by truffaldino View Post
At this reynolds number the flow is transitional. E.g. at zero angle of attack transition to turbulent at this Re and this airfoil happens at about 80-90% of the wing chord. At angle attack 5deg it happens at about 25% of wing chord.

Using turbulence models in CFD-software without special user input will likely give very wrong results for drag at such reynolds number.

Truffaldino
Truffaldino ,

Sorry for my poor knowledge, how to determine which reynolds number is laminar or turbulent? I google it and cant find the knowledge i want. Any source for me to study?

I face problems in drag coefficient where it is different from the published papers.
Tom Lucius is offline   Reply With Quote

Old   March 29, 2012, 06:40
Default
  #7
Senior Member
 
truffaldino's Avatar
 
Join Date: Jan 2011
Posts: 234
Blog Entries: 5
Rep Power: 8
truffaldino is on a distinguished road
Hello Tom,

Your question where the flow is turbulent and where is laminar is not an easy question: this is one of the difficult problems of fluid dynamics and the answer depends not only on reynolds number, but also on problem geometry, boundary condition and amount of free-stream turbulence. In your case flow is neither turbulent nor laminar, there will be a transition from the laminar to turbulent flow somewhere.

In the above examples I have used XFOIL program to find the transition location: For instance, at zero angle of attack and Re=3.6E5 the flow is laminar at both sides of airfoil up to approximately 80% of the airfoil chord and it becomes turbulent after.
For angle of attack 5 deg the flow is fully laminar at lower side of airfoil. At upper side it is laminar up to 25% of the chord and turbulent after.

X-foil is so far the best software for analysing flows past conventional airfoils at low reynolds numbers: it is more accurate in predicting drag than RANS modelling. This program is free and easy to use.

So, before using CFD software with RANS I reccomend you to run XFOIL analysys to have an idea what to expect, where to expect flow separation and reattachment, transition etc.

Truffaldino
truffaldino is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Drag and Lift coefficient (NACA 0012) remi_fr STAR-CCM+ 17 March 2, 2015 17:23
Lift and Drag Coefficient data for NACA 2412 Airfoil mahbub03 Main CFD Forum 22 May 25, 2014 15:39
Lift and drag coefficient with strange values for NACA airfoil antonio_ing OpenFOAM Running, Solving & CFD 16 September 13, 2012 12:21
Automotive test case vinz OpenFOAM Running, Solving & CFD 98 October 27, 2008 09:43
drag and lift coefficient No CD-adapco 5 July 13, 2004 10:21


All times are GMT -4. The time now is 17:37.