CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > NUMECA

darft tube and francis(runner,guide,stay)

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By colinda1

Reply
 
LinkBack Thread Tools Display Modes
Old   December 31, 2013, 07:04
Default darft tube and francis(runner,guide,stay)
  #1
New Member
 
Arvin Hosseinnejad
Join Date: Dec 2013
Posts: 2
Rep Power: 0
arvindarwin is on a distinguished road
Dear all,

Im new to numeca I have 2 simple questions?

1. what is the step after mesh generation in iGG. i want to generate darft tube mesh and perform solving. In which modul, numeca solves generated mesh?
Is that Euranus?!

2. How can i analyze francis turbine runner together whit draf tube and spiral casing in one analyze enviroment.(assembled to each other)?


Thank you
arvindarwin is offline   Reply With Quote

Old   January 16, 2014, 11:36
Default
  #2
Member
 
Colinda
Join Date: May 2012
Posts: 39
Rep Power: 5
colinda1 is on a distinguished road
1. After the mesh generation you can define the flow solver input in FINE/Turbo GUI and from there launch the computation that is done in the solver EURANUS.

2. You can mesh your runner in AutoGrid5 and then put it together with the mesh of the draft tube and the spiral casing in two ways:
- if you have access to AutoGird5 advanced modules, you can import these meshes in AutoGrid5 environment as a 3D effect. This has the advantage that it is included in the template so if you change the geometry of the runner or the other meshes, you can easily recreate your complete mesh.
- otherwise you can go in IGG, open the draft tube mesh and then use File/Import/IGG Project to import the runner and the same for the spiral casing. Then you need to specify the right boundary conditions at the connection between these meshes (rotor/stator interface).
colinda1 is offline   Reply With Quote

Old   January 16, 2014, 19:28
Default
  #3
New Member
 
Arvin Hosseinnejad
Join Date: Dec 2013
Posts: 2
Rep Power: 0
arvindarwin is on a distinguished road
Colinda thank you for your reply. it was so helpfull.
I just performed matter in different way. Draft tube mesh generation in hexpress from imported parasolid cad file and after that imported runner
as igg project to hexpress module and then performing solution in Fine/open.
but what you describe above has advantage i think as i can do modifications on runner during process .its will be really helpfull.

I just want to ask what do you mean by advanced Autogird5 modules? could you please explain a bit more.

Thank you very much
arvindarwin is offline   Reply With Quote

Old   January 17, 2014, 03:55
Default
  #4
Member
 
Colinda
Join Date: May 2012
Posts: 39
Rep Power: 5
colinda1 is on a distinguished road
Indeed, if you make a mesh for the draft tube and spiral casing in HEXPRESS, my suggestion staying within the structured package FINE/Turbo is no longer possible as any mesh that contains (partly) unstructured meshes must be solved in FINE/Open with OpenLabs.

In that case the way you followed is the correct one. You can still save time
using scripts in case you would like to run simulations for many runner geometries. The first time you put your mesh together in HEXPRESS you can save these steps in Project/Scripts/Save All
Then you can easily relaunch the same script. In a shell script you can then automatically launch AutoGrid5 to make the runner mesh and copy the created mesh to a temporary location (to make sure you keep the original versions of the various runner meshes).
Then launch the recorded script in batch in HEXPRESS with the path of course set to the same temporary location. All batch commands to launch AutoGrid5, HEXPRESS, the solver and post processing can be found in the manual.

If you have a license for the advanced modules of AutoGrid5, it allows you in expert mode (selection at the top right of the GUI) to add in the Row Definition section at the top left a 3D effect to a selected row. In the manual you'll find a section dedicated to 3D Technological effects. But as I said, in the case you made your other meshes in HEXPRESS, this is of no use in your case and you have to assemble the components in HEXPRESS.
arvindarwin likes this.
colinda1 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
What is best mesh for cylinder tube? olivia FLUENT 7 January 16, 2014 06:55
Tube filter in Paraview werweisswas OpenFOAM Paraview & paraFoam 0 December 10, 2012 07:18
How to set up a dynamic mesh for a piston moving through a tube of variable diameter? karkar OpenFOAM Meshing & Mesh Conversion 0 July 4, 2012 06:54
Hydraucone Draft Tube CFD tojoe999 OpenFOAM 0 March 5, 2012 14:10
HLL Riemann Shock Tube Matlab Problem Luke F Main CFD Forum 1 July 7, 2009 13:44


All times are GMT -4. The time now is 04:50.