How to identify cell neighbours
 

Hello,

i am new in openFoam and i don´t know how to identify and output the neighbours of a cell[i]!

Is it possible in openFaom?

I hope someone can help me!

Thanks and kind regards
Khaled

Hi Khaled mesh.cellCell
 

Hi Khaled

mesh.cellCells()[cellI] gives the neighbours of cell cellI

su junwei

Hi su junwei, thanks very m
 

Hi su junwei,

thanks very much.

And with "Info<< mesh.cellCells()[celli]<< endl;" I put out the neighbours of celli?

Regards,
Khaled

Yes, Khaled, you can print the
 

Yes, Khaled, you can print them out. This is a list of cell index in the neighbourhood.
Junwei

Thanks Su. I´ll try it now.
 

Thanks Su. I´ll try it now.

Btw. do you know how to integrate over a special patch or is it possible with openfoam?

Thanks and regards
khaled

Hi Khaled patchIntegra
 

Hi Khaled

patchIntegrate can be used to integrate over a special patch, you can use it like this

patchIntegrate fieldname patchname.

This is a postprocessing utility.

Junwei

Hi Su Junwei, oh ok, thanks
 

Hi Su Junwei,

oh ok, thanks.

But mybe i hope you ask my last question here.

Exactly i want to integrate over the patch "outlet" of the pressure field "p". So then i only write

patchIntegrate p [1]

if the patchname is [1]?

Thanks,
Khaled

Hi khaled yes. That's Ok.
 

Hi khaled
yes. That's Ok. Just test it.
Junwei

number of cell neighbours
 

Hi Su,

Thanks for the hint, it was very helpful. I was wondering if there is a command to find the number of cell neighbours for a cell.

mesh.cellCells()[cellI] gives <no. of neighbouring cells>(<neighbours>)

If I want just the <no. of neighbouring cells> alone, how do I get it ?

Thanks.

Hi Ritu

Just using the size function like this
label neighbourCount=mesh.cellCells()[cellI].size()

sorry for late response
Junwei

closest cell from point
 

Hi Su Junwei and Khaled,

Does anyone know how to select the closest cell near the point (x,y,z)?

Thank you,

Pascal

Hi Pascal
you can use the following code

meshSearch ms(mesh);
label nearestCellIndex = ms.findNearestCell(p);

p is your point for searching nearest cell. nearestCellIndex is the cell index that you want.
Don't forget to include "meshSearch.H"

Junwei

Hi Pascal,

alternatively you can use

label labelOfClosestCell mesh.findCell(c y z);


Best Kathrin

Hi

I was looking in the forum and I hope you might help me?

I want to identify cells whose face(s) are in a patch and give them a value

what would it the the best way ?

Thanks


O. R.

post processing
 

Hi everybody,

I am trying to model a free turbulent jet with LES. In part of my project I have to determine value of some variables along a specific line inside my domain to compare my results with my refrences results but I dont know how I can do that?
I would appreciate any help.

best regards,
Yashar

Just use sample tool in OpenFOAM. see Openfoam's user's guide

Just use faceCells in polyPatch class.

faceCells give you the index of a cell who owns the current patch face.

Regards, Junwei

Hi Su,

thank you very much for your response.
indeed, I want to compute my jet width along the jet centreline. for that reason, I have to determine the centreline velocity(u(x,0,0)) that is function of x-axis then compute distance from jet centreline in y-direction where the x component of velocity become half of the centreline velocity.
is there any utility that can do that for me or I have to write a code?

A possible way can be described as follows:
1) Cut several planes along centreline transversely.
2) select points on these planes. These points are not necessary on the cell center.
3) interpolate values to the selected points
4) find the point who has maximum velocity on each plane, and this point is on the cenerline
5) loop all the planes. In each planes, fix Y, and change z from min to maximum, and find the two points who has the most approaching value to half the maximum velocity. Distance between these two points is the jet width on this line. In 3D the wide should be different for different Y.

The points you selected shoud cover your jets. The algorithm is an approximated method.

If you have problem in implementation, please let me know.

Regards, Junwei

Hi Su

I really appreciate all the help you gave me.
basically, I think that it would better for me to export my result to a .dat file and write a separate(from OF) code to digest in my data but I would appreciate if you could answer my question:
how I could export my data so that I could specify and link for each point(cell centre) , the position(x,y,z) and velocity(u,v,w) variables of that point as a same file?


Best regards,
Yashar