CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM Meshing & Mesh Conversion

Simple mesh of a room with floor patch

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 13, 2013, 04:31
Default Simple mesh of a room with floor patch
  #1
New Member
 
JCFD
Join Date: Feb 2013
Posts: 4
Rep Power: 4
jlp56 is on a distinguished road
Hi,

I am very new to CFD, meshing and alike, I am usually an experimentalist. Still, I would like to become more proficient. I think I understand the basics of OpenFOAM, worked through the tutorials etc. but I am struggling to mesh the simplest of enclosures!

Essentially, I would like a cube with a small patch on the floor (ideally a circle but for simplicity a square patch would do) which I can then apply a constant heat flux condition to. I know how to apply the boundary conditions but I am struggling to mesh it up with BlockMesh. I initially tried to mesh a 2D model of such flow, so with a small square in the middle of the base of the enclosure that I can apply heat to but also struggled as it kept throwing the error that the cell had no neighbouring face.

In the grand schemes of things, I would like to position this small cube with heated patch and a couple of openings, inside a larger cube.

It sounds simple in theory, and I am sure it is, but I have trouble with the vertices, as adding a smaller square inside the larger base square of the enclosure seems to throw up errors.

Any help would be greatly appreciated.
jlp56 is offline   Reply With Quote

Old   March 14, 2013, 21:24
Default
  #2
New Member
 
Lucas
Join Date: Jul 2012
Posts: 7
Rep Power: 5
lucasw7 is on a distinguished road
Hi,

Do you have access to a CAD Program? If so, you could model your smaller cube with that, save as an STL file and use snappyHexMesh function.
To start you off, I would recommend you take a look at this tutorial:
https://sites.google.com/site/snappy.../cylinder-case

This should help you understand the snappyHexMesh utility, which you should use as it'd be a much easier approach then blockMesh.

However should you attempt to do it in blockMesh, see below - 5x5x5 metre cube with 1x1x1 metre patch (labelled hole) in the middle. Best you get a pencil and paper and mark all the coordinates in order to get an understanding of how each point is projected to it's opposite face, and ordering of coordinates for the patches and walls.



/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: 2.1.1 |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object blockMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

convertToMeters 1;

vertices
(
(0 0 0) //0
(2 0 0) //1
(3 0 0) //2
(5 0 0) //3
(0 0 2) //4
(2 0 2) //5
(3 0 2) //6
(5 0 2) //7
(0 0 3) //8
(2 0 3) //9
(3 0 3) //10
(5 0 3) //11
(0 0 5) //12
(2 0 5) //13
(3 0 5) //14
(5 0 5) //15
(0 5 0) //16
(2 5 0) //17
(3 5 0) //18
(5 5 0) //19
(0 5 2) //20
(2 5 2) //21
(3 5 2) //22
(5 5 2) //23
(0 5 3) //24
(2 5 3) //25
(3 5 3) //26
(5 5 3) //27
(0 5 5) //28
(2 5 5) //29
(3 5 5) //30
(5 5 5) //31



);

blocks
(
hex (0 1 5 4 16 17 21 20) (2 2 5) simpleGrading (1 1 1)
hex (1 2 6 5 17 18 22 21) (1 2 5) simpleGrading (1 1 1)
hex (2 3 7 6 18 19 23 22) (2 2 5) simpleGrading (1 1 1)
hex (4 5 9 8 20 21 25 24) (2 1 5) simpleGrading (1 1 1)
hex (5 6 10 9 21 22 26 25) (1 1 5) simpleGrading (1 1 1)
hex (6 7 11 10 22 23 27 26) (2 1 5) simpleGrading (1 1 1)
hex (8 9 13 12 24 25 29 28) (2 2 5) simpleGrading (1 1 1)
hex (9 10 14 13 25 26 30 29) (1 2 5) simpleGrading (1 1 1)
hex (10 11 15 14 26 27 31 30) (2 2 5) simpleGrading (1 1 1)
);

edges
(
);

boundary
(
hole
{
type patch;
faces
(
(5 9 10 6)
);
}


wall
{
type wall;
faces
(
(0 1 17 16)
(1 2 18 17)
(2 3 19 18)
(3 7 23 19)
(7 11 27 23)
(11 15 31 27)
(14 30 31 15)
(13 29 30 14)
(12 28 29 13)
(8 24 28 12)
(4 20 24 8)
(0 16 20 4)
(0 4 5 1)
(1 5 6 2)
(2 6 7 3)
(4 8 9 5)
(6 10 11 7)
(8 12 13 9)
(9 13 14 10)
(10 14 15 11)
(16 17 21 20)
(17 18 22 21)
(18 19 23 22)
(20 21 25 24)
(21 22 26 25)
(22 23 27 26)
(24 25 29 28)
(25 26 30 29)
(26 27 31 30)

);
}
);

mergePatchPairs
(
);

Luke
lucasw7 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] Generating Mesh for STL Car in Windtunnel Simulation tommymoose ANSYS Meshing & Geometry 48 April 15, 2013 04:24
No layers in a small gap bobburnquist OpenFOAM Native Meshers: snappyHexMesh and Others 2 November 25, 2012 09:54
erroneous temps in conjugate model? sieginc. STAR-CCM+ 11 July 14, 2012 03:41
external flow with snappyHexMesh chelvistero OpenFOAM 11 January 15, 2010 20:43
Very simple moving mesh Pete FLUENT 4 February 10, 2006 01:12


All times are GMT -4. The time now is 19:06.