
[Sponsors] 
May 11, 2013, 09:06 
wallHeatTransfer chtMulti on solid region

#1 
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,125
Blog Entries: 6
Rep Power: 20 
Hi all,
I am calculating a heated pipe (air = 800K) and do not want to simulate the air around that pipe but want to set a heattransfer BC for that. There for I thought its possible to work with the BC Code:
wallHeatTransfer So the question to you all: is there a other BC for that or some examples with groovy? Thanks in advance. Tobi 

May 11, 2013, 09:30 

#2 
Member
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 5 
Just that I got you right. The air with 800K is flowing around the pipe and heats it up. The heat conducts through the wall and in turn heats up the fluid within the pipe.
Instead of solving the air around the pipe you can either apply a heat flux or a heat transfer coefficient and the ambient temperature at the wall using the externalWallHeatFluxTemperature boundary condition. 

May 11, 2013, 09:36 

#3  
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,125
Blog Entries: 6
Rep Power: 20 
Quote:
Hi, in the attachement there you find a picture. I think that tells everyone more then words.  in the pipe is air with T=800K and flows inside through the pipe.  heattransfer between fluid and solid due to chtMutli calculations  at least I want to make the case more realistic. for that I want to create/calculate the heat transfer from the solid to the ambience air. So my options are:  building the airdomain and create a new mappedWall for pipe>new_air_domain  or doing it with a BC like groovy? Hope everything is clear now 

May 11, 2013, 09:50 

#4 
Member
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 5 
Okay so the air inside the pipe heats up the pipe walls and you want to add conduction on the outer wall of the pipe. I think the boundary condition I mentioned above should do the trick. Just use a negative heat flux or heat flux coefficient.
If you want somewhat correct solid temperatures you have to do this anyway else you will end up with 800K for the solid wall. 

May 11, 2013, 09:55 

#5 
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,125
Blog Entries: 6
Rep Power: 20 
Hi billie,
thanks for your replay. The problem for the "heat flux" is that its not possible to calculate that. The air = 800K changes in 1sec to 293K (thermal shock) and then the heat flux is completly different ... thats my problem. 

May 11, 2013, 10:28 

#6  
Member
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 5 
Quote:
If you don't know the heat flux you can use the heat flux coefficient in combination with the ambient temperature.The convective heat transfer coefficient should be around 35W/m^2/K. You can also estimate the heat flux coefficient using the formulas for natural convection of external flow around a cylinder from [1]. [1] http://en.wikipedia.org/wiki/Heat_tr...ral_convection 

May 11, 2013, 14:04 

#7 
Senior Member
PeiYing Hsieh
Join Date: Mar 2009
Posts: 275
Rep Power: 9 
Hi, Tobi,
To clarify what Daniel suggested. Use the following for the external wall of the pipe: myPatch { type externalWallHeatFluxTemperature; kappa solidThermo; // solidThermo or lookup // q uniform 1000; // heat flux / [W/m2] Ta uniform 300.0; // ambient temperature /[K] h uniform 10.0; // heat transfer coeff /[W/Km2] value uniform 300.0; // initial temperature / [K] kappaName none; }  PeiYing 

August 7, 2013, 02:19 

#9 
Member
MSarkar
Join Date: Dec 2009
Posts: 99
Rep Power: 7 
Hi Tobi,
You mentioned that you solved this yourself. Could please let me know what exactly you did? In your case did you model that pipe as a thick solid or solid thin wall? Did you use externalWallHeatFluxTemperature BC to a solid region? Thanks in advance. m sarkar 

December 5, 2013, 08:39 

#10  
Member
Thamali
Join Date: Jul 2013
Posts: 55
Rep Power: 4 
Quote:


December 19, 2013, 12:20 

#11  
New Member
aelab VUB
Join Date: Oct 2011
Posts: 17
Rep Power: 6 
Quote:


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Error finding variable "THERMX"  sunilpatil  CFX  8  April 26, 2013 07:00 
Using starToFoam  clo  OpenFOAM Other Meshers: ICEM, Star, Ansys, Pointwise, GridPro, Ansa, ...  33  September 26, 2012 04:04 
StarToFoam error  Kart  OpenFOAM Meshing & Mesh Conversion  1  February 4, 2010 05:38 
Import gmsh msh to Foam  adorean  Open Source Meshers: Gmsh, Netgen, CGNS, ...  24  April 27, 2005 08:19 
CFX4.3 build analysis form  Chie Min  CFX  5  July 12, 2001 23:19 