CFD Online URL
[Sponsors]
Home > Forums > OpenFOAM Pre-Processing

wallHeatTransfer chtMulti on solid region

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 11, 2013, 10:06
Default wallHeatTransfer chtMulti on solid region
  #1
Senior Member
 
Tobi's Avatar
 
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 988
Blog Entries: 4
Rep Power: 18
Tobi will become famous soon enough
Send a message via ICQ to Tobi Send a message via Skype™ to Tobi
Hi all,

I am calculating a heated pipe (air = 800K) and do not want to simulate the air around that pipe but want to set a heat-transfer BC for that.

There for I thought its possible to work with the BC
Code:
wallHeatTransfer
but thats not working due to the turbulenceModel (not avaiable for the solid region).

So the question to you all: is there a other BC for that or some examples with groovy?

Thanks in advance.
Tobi
Tobi is offline   Reply With Quote

Old   May 11, 2013, 10:30
Default
  #2
Member
 
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 4
billie is on a distinguished road
Just that I got you right. The air with 800K is flowing around the pipe and heats it up. The heat conducts through the wall and in turn heats up the fluid within the pipe.

Instead of solving the air around the pipe you can either apply a heat flux or a heat transfer coefficient and the ambient temperature at the wall using the externalWallHeatFluxTemperature boundary condition.
billie is offline   Reply With Quote

Old   May 11, 2013, 10:36
Default
  #3
Senior Member
 
Tobi's Avatar
 
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 988
Blog Entries: 4
Rep Power: 18
Tobi will become famous soon enough
Send a message via ICQ to Tobi Send a message via Skype™ to Tobi
Quote:
Originally Posted by billie View Post
Just that I got you right. The air with 800K is flowing around the pipe and heats it up. The heat conducts through the wall and in turn heats up the fluid within the pipe.

Instead of solving the air around the pipe you can either apply a heat flux or a heat transfer coefficient and the ambient temperature at the wall using the externalWallHeatFluxTemperature boundary condition.

Hi,

in the attachement there you find a picture. I think that tells everyone more then words.

- in the pipe is air with T=800K and flows inside through the pipe.
- heat-transfer between fluid and solid due to chtMutli calculations

- at least I want to make the case more realistic. for that I want to create/calculate the heat transfer from the solid to the ambience air.


So my options are:

- building the air-domain and create a new mappedWall for pipe->new_air_domain
- or doing it with a BC like groovy?


Hope everything is clear now
Attached Images
File Type: jpg heatedPipe.jpg (11.6 KB, 42 views)
Tobi is offline   Reply With Quote

Old   May 11, 2013, 10:50
Default
  #4
Member
 
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 4
billie is on a distinguished road
Okay so the air inside the pipe heats up the pipe walls and you want to add conduction on the outer wall of the pipe. I think the boundary condition I mentioned above should do the trick. Just use a negative heat flux or heat flux coefficient.

If you want somewhat correct solid temperatures you have to do this anyway else you will end up with 800K for the solid wall.
billie is offline   Reply With Quote

Old   May 11, 2013, 10:55
Default
  #5
Senior Member
 
Tobi's Avatar
 
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 988
Blog Entries: 4
Rep Power: 18
Tobi will become famous soon enough
Send a message via ICQ to Tobi Send a message via Skype™ to Tobi
Hi billie,

thanks for your replay.

The problem for the "heat flux" is that its not possible to calculate that.

The air = 800K changes in 1sec to 293K (thermal shock) and then the heat flux is completly different ... thats my problem.
Tobi is offline   Reply With Quote

Old   May 11, 2013, 11:28
Default
  #6
Member
 
Daniel Pielmeier
Join Date: Apr 2012
Posts: 96
Rep Power: 4
billie is on a distinguished road
Quote:
Originally Posted by Tobi View Post
The problem for the "heat flux" is that its not possible to calculate that.

The air = 800K changes in 1sec to 293K (thermal shock) and then the heat flux is completly different ... thats my problem.
Sorry I meant convection on the outer pipe wall instead of conduction.

If you don't know the heat flux you can use the heat flux coefficient in combination with the ambient temperature.The convective heat transfer coefficient should be around 3-5W/m^2/K.

You can also estimate the heat flux coefficient using the formulas for natural convection of external flow around a cylinder from [1].

[1] http://en.wikipedia.org/wiki/Heat_tr...ral_convection
billie is offline   Reply With Quote

Old   May 11, 2013, 15:04
Default
  #7
Senior Member
 
Pei-Ying Hsieh
Join Date: Mar 2009
Posts: 269
Rep Power: 8
phsieh2005 is on a distinguished road
Hi, Tobi,

To clarify what Daniel suggested. Use the following for the external wall of the pipe:

myPatch
{
type externalWallHeatFluxTemperature;
kappa solidThermo; // solidThermo or lookup
// q uniform 1000; // heat flux / [W/m2]
Ta uniform 300.0; // ambient temperature /[K]
h uniform 10.0; // heat transfer coeff /[W/Km2]
value uniform 300.0; // initial temperature / [K]
kappaName none;
}
-----------------

Pei-Ying
phsieh2005 is offline   Reply With Quote

Old   May 11, 2013, 16:00
Default
  #8
Senior Member
 
Tobi's Avatar
 
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 988
Blog Entries: 4
Rep Power: 18
Tobi will become famous soon enough
Send a message via ICQ to Tobi Send a message via Skype™ to Tobi
Hi,.

thanks for your replay
But I figured it out by my self (-> code)

But thanks a lot

Tobi
Tobi is offline   Reply With Quote

Old   August 7, 2013, 03:19
Default
  #9
Member
 
MSarkar
Join Date: Dec 2009
Posts: 99
Rep Power: 7
msarkar is on a distinguished road
Hi Tobi,

You mentioned that you solved this yourself. Could please let me know what exactly you did? In your case did you model that pipe as a thick solid or solid thin wall? Did you use externalWallHeatFluxTemperature BC to a solid region?

Thanks in advance.
m sarkar
msarkar is offline   Reply With Quote

Old   December 5, 2013, 08:39
Default
  #10
Member
 
Thamali
Join Date: Jul 2013
Posts: 54
Rep Power: 3
Thamali is on a distinguished road
Quote:
Originally Posted by billie View Post
Sorry I meant convection on the outer pipe wall instead of conduction.

If you don't know the heat flux you can use the heat flux coefficient in combination with the ambient temperature.The convective heat transfer coefficient should be around 3-5W/m^2/K.

You can also estimate the heat flux coefficient using the formulas for natural convection of external flow around a cylinder from [1].

[1] http://en.wikipedia.org/wiki/Heat_tr...ral_convection
Is this BC is possible to apply for enthalpy as well?
Thamali is offline   Reply With Quote

Old   December 19, 2013, 12:20
Default
  #11
New Member
 
ae-lab VUB
Join Date: Oct 2011
Posts: 17
Rep Power: 5
aevub is on a distinguished road
Quote:
Originally Posted by msarkar View Post
Hi Tobi,

You mentioned that you solved this yourself. Could please let me know what exactly you did? In your case did you model that pipe as a thick solid or solid thin wall? Did you use externalWallHeatFluxTemperature BC to a solid region?

Thanks in advance.
m sarkar
also interested
aevub is offline   Reply With Quote

Old   December 19, 2013, 17:45
Default
  #12
Senior Member
 
Tobi's Avatar
 
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 988
Blog Entries: 4
Rep Power: 18
Tobi will become famous soon enough
Send a message via ICQ to Tobi Send a message via Skype™ to Tobi
Hmmm....

have a look at the availabe BC
Tobi is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Error finding variable "THERMX" sunilpatil CFX 8 April 26, 2013 08:00
Using starToFoam clo OpenFOAM Other Meshers: ICEM, Star, Ansys, Pointwise, GridPro, Ansa, ... 33 September 26, 2012 05:04
StarToFoam error Kart OpenFOAM Meshing & Mesh Conversion 1 February 4, 2010 05:38
Import gmsh msh to Foam adorean Open Source Meshers: Gmsh, Netgen, CGNS, ... 24 April 27, 2005 09:19
CFX4.3 -build analysis form Chie Min CFX 5 July 13, 2001 00:19


All times are GMT -4. The time now is 03:23.