CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM Pre-Processing

MapFields

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   January 28, 2005, 01:38
Default When I map fields from one ca
  #1
Luiz Eduardo Bittencourt Sampaio (Sampaio)
Guest
 
Posts: n/a
When I map fields from one case to another, are the cutting patches defined as "fixedGradients" read and mapped also? I mean, will my new case have fixedGradient at those boundaries, set exactly to the same values as the "old" case?

Please if possible, give directions on how would I discover that myself, so I dont bother you in the future with other questions
  Reply With Quote

Old   January 28, 2005, 03:50
Default For what it is worth, mapField
  #2
Chris Greenshields (Chris)
Guest
 
Posts: n/a
For what it is worth, mapFields is documented a bit in:
http://www.opencfd.co.uk/openfoam/doc/userse25.html

Apart from that, why not look at the field files themselves and see what the new case inherits from the old case? The syntax is easy to understand:
http://www.opencfd.co.uk/openfoam/doc/userse12.html#x19-1030004.2.7

Hope this helps, Chris
  Reply With Quote

Old   January 28, 2005, 15:34
Default Hi Crhis, It does not map gr
  #3
Luiz Eduardo Bittencourt Sampaio (Sampaio)
Guest
 
Posts: n/a
Hi Crhis,
It does not map grad boundary values. But in Jasak Thesis, if I am not mistaken, it is mentioned that one can map gradients at boundary (chapter about adaptive mesh refinement).
Is there any easy way to do that?
Regards,
Luiz
  Reply With Quote

Old   February 14, 2006, 10:30
Default Another question regarding map
  #4
New Member
 
Carl Troeng
Join Date: Mar 2009
Location: Sweden
Posts: 2
Rep Power: 0
carl_troeng is on a distinguished road
Another question regarding mapFields:

Is it possible to change the interpolation scheme mapFields uses?
(If I understand correctly, this can not be set in fvSchemes or mapFieldsDict.)
What would be the best way to keep the divergence free property when mapping a field between two meshes?
carl_troeng is offline   Reply With Quote

Old   February 20, 2006, 05:09
Default Hi All! In order to estimat
  #5
Member
 
Masashi IMANO
Join Date: Mar 2009
Location: Tokyo, Japan
Posts: 34
Rep Power: 8
imano is on a distinguished road
Hi All!

In order to estimate the solution error on a coarse mesh,
I tried to map a solution on a finer mesh onto the orignal
coarse mesh with mapFileds utility.

But the mapped solution and the original solution are
seriously differ especially in a near-wall region when the normal
distances of the near-wall cell are the same in two meshs.

If we add meshToMesh::MAP option when we use a meshToMesh.interpolate
function in mapFields/MapConsistentVolFields.H or MapVolFields.H (i.e.
we use a direct mapping of nearest-cell values), we won't get severe
difference, but at the same time it won't be smooth.

In addition to that the default interpolation scheme used in the
mapFields (i.e. INTERPOLATION option) is an inverse distance
interpolation, so it seems to me that the mapped results may not have
the second order accuracy (i.e. not linear interpolation). This may
not be a problem when we use it in order to make initial guess on a
finer mesh, but it would not be acceptable in case of measuring a
differences between solutions on different meshes in detail.

So I also tried to use meshToMesh::CELL_POINT_INTERPOLATE which seems
to handle linear interpolation, but the serious inconsitency in the
near-wall region doesn't disappear.

Now I have two questions:

a) Can I consider that the CELL_POINT_INTERPOLATE options actually do
the linear interpolation?

b) Is there any good idea to avoid the inconsistency without using
the the direct mapping.


I attached a sample test case file about the mentioned above, please
try it if you have a spare time!

mapFieldsTest.tar.gz
imano is offline   Reply With Quote

Old   February 21, 2006, 01:59
Default Hello and sorry for my frequen
  #6
Member
 
Masashi IMANO
Join Date: Mar 2009
Location: Tokyo, Japan
Posts: 34
Rep Power: 8
imano is on a distinguished road
Hello and sorry for my frequent post!

The test case I attached yesterday was extremely not good example.
So I made another test case.

In this case we first calculates a turbulent flow over backward-facing
step (Re=5500) on a fine mesh.

In the next step we maps the results onto a coarse mesh using
mapFields with several interpolation scheme: INTERPOLATION(default),
MAP, CELL_POINT_INTERPOLATION.

In order to avoid violating the limit of y+ condition of the wall
function, the height of the cell near the wall is same between two
meshes.

Finally we sample velocity field on the obtained results at the same
profile lines which pass through center of cells on the coarse mesh
and compare them using plotting program: gnuplot.

You will see the severe inconsistency near the wall between the
velocity profile on the fine mesh and the mapped profile with using
CELL_POINT_INTERPOLATION option.
But at the same time CELL_POINT_INTERPOLATION makes the best accuracy
in the inner region.

Regards,
Masashi

mapFieldsTest2.tar.gz
imano is offline   Reply With Quote

Old   February 21, 2006, 22:22
Default I don't want to run the exampl
  #7
Senior Member
 
Hrvoje Jasak
Join Date: Mar 2009
Location: London, England
Posts: 1,763
Rep Power: 21
hjasak will become famous soon enough
I don't want to run the examples myself - how about posting some pictures of your problems instead of posting the code?

Could you give me some more detail on what you are after. The mapping algorithm will basically find a master cell for each cell of the new mesh and grab the data. The easiest way of doing this is just to use the same value; somewhat more sophisticated is a gradient (or inverse distance-based) interpolation, either using cell or point values. If you expect the near-wall interpolation to recognise that you are in the log-law region and do the interpolation based on log distribution, it won't do it. Of course, you can always add the code to handle that case if you want.

Hrv
__________________
Hrvoje Jasak
Providing commercial FOAM/OpenFOAM and CFD Consulting: http://wikki.co.uk
hjasak is offline   Reply With Quote

Old   February 22, 2006, 07:02
Default Dear Hrvoje, Why didn't I t
  #8
Member
 
Masashi IMANO
Join Date: Mar 2009
Location: Tokyo, Japan
Posts: 34
Rep Power: 8
imano is on a distinguished road
Dear Hrvoje,

Why didn't I think of posting pictures!

Here are pictures.







I don't think of such an interpolation based on a log distribution.
I just want the gradient interpolation even in the near-wall region.

Best regards,
Masashi
imano is offline   Reply With Quote

Old   February 22, 2006, 07:19
Default Sorry, I don't know that "Tex
  #9
Member
 
Masashi IMANO
Join Date: Mar 2009
Location: Tokyo, Japan
Posts: 34
Rep Power: 8
imano is on a distinguished road
Sorry, I don't know that "Text description" in the image tag disappers. So I forget to write description of figures in my previous post.

Title of figures are

-Fine mesh
-Coarse mesh
-Velocity vectors on the coarse mesh
-Velocity profile behind the step
-Velocity profile near the floor

from the top respectively.

Regards,
Masashi
imano is offline   Reply With Quote

Old   February 27, 2006, 11:41
Default Dear all, I found that the
  #10
Member
 
Masashi IMANO
Join Date: Mar 2009
Location: Tokyo, Japan
Posts: 34
Rep Power: 8
imano is on a distinguished road
Dear all,

I found that the above mentioned severe inconsistency near wall
is due to the nature of cell-point interpolation.
This interpolation makes a tet with the center point of a cell which
contains the mapping target point and three vertices of that cell.
As a value on a face center is never used in this interpolation,
weight on the cell center value is regarded as zero if we interpolate
value on the face center.
On the other hand weight on a wall boundary is a half.
So the interpolated value near wall is affected by the boundary value
excessively in spite of the existence of high gradient in the
near-wall region.

We can avoid this problem if we use cell-point-face interpolation
which handle the face center value.


Fig. interpolation schemes

So I added CELL_POINT_FACE_INTERPOLATE option to interpolation
function in meshToMesh class and recompile mapFields to use that. As a
result the recompiled mapFields would be able to map fields linearly
for the most part.

This is the patch for the meshToMesh class.

meshToMesh.patch.gz

Regards,
Masashi
imano is offline   Reply With Quote

Old   November 29, 2006, 20:11
Default Dear All, Could somebosy pl
  #11
felic
Guest
 
Posts: n/a
Dear All,

Could somebosy please let me know how to use the command:
mapFields <source> <source> <target> <target> [-consistent] [-parallelSource] [-parallelTarget]
please?

cheers,
fel!c
  Reply With Quote

Old   January 4, 2007, 10:40
Default mapFields on inconsistent geom
  #12
Senior Member
 
Maka Mohu
Join Date: Mar 2009
Posts: 305
Rep Power: 9
maka is on a distinguished road
mapFields on inconsistent geometries.

I run mapFields between two inconsistent geometries. The source is double the hight of the target. Both are like channel395 geometry but with 4 blocks. The mapFieldsDict reads:

patchMap
(
bottomWall bottomWall
inout1 inout1
sides1 sides1
);

cuttingPatches
(
topWall
);
the command return successfully without errors but the time folder is not created in the target case directory.

I ran under gdb and it said Program exited normally.

here are some output:

Create databases as time

Source time: 1
Target time: 1
Create meshes

Source mesh size: 52800 Target mesh size: 26400


Mapping fields for time 1


End
can anyone guess the reason? Thanks.

best regards,
Maka
maka is offline   Reply With Quote

Old   January 4, 2007, 10:48
Default You did not set the "time-from
  #13
Senior Member
 
Hrvoje Jasak
Join Date: Mar 2009
Location: London, England
Posts: 1,763
Rep Power: 21
hjasak will become famous soon enough
You did not set the "time-from" and "time-to" correctly. I presume there is no time 1 in your source case, so there's no fields to map.

Hrv
__________________
Hrvoje Jasak
Providing commercial FOAM/OpenFOAM and CFD Consulting: http://wikki.co.uk
hjasak is offline   Reply With Quote

Old   January 4, 2007, 11:31
Default Actually, there were no target
  #14
Senior Member
 
Maka Mohu
Join Date: Mar 2009
Posts: 305
Rep Power: 9
maka is on a distinguished road
Actually, there were no target directory (I'm used to -consistent option). I made one by coping from i.c. and it worked OK. Thanks for your quick help!

Best regards,
Maka.
maka is offline   Reply With Quote

Old   December 4, 2007, 12:35
Default Hi everybody. I'm trying to m
  #15
New Member
 
Hyunchang Lee
Join Date: Mar 2009
Location: Daejeon, Korea
Posts: 11
Rep Power: 8
asteria is on a distinguished road
Hi everybody.
I'm trying to map from coarser mesh to finer mesh , using mapFields utility. But, the problem is that it doesn't give exact interpolated value.
I increased the number of cells twice and the change is like below.

-------------------------------------------------
---------before-------------------------------
------------------------------------------------
boundaryField
{
inlet
{
type fixedValue;
value nonuniform List<vector>
18
(
(0.005401235 0 0)
(0.015277778 0 0)
(0.023919753 0 0)
(0.031327160 0 0)
(0.037500000 0 0)
(0.042438272 0 0)
(0.046141975 0 0)
(0.048611111 0 0)
(0.049845679 0 0)
(0.049845679 0 0)
(0.048611111 0 0)
(0.046141975 0 0)
(0.042438272 0 0)
(0.037500000 0 0)
(0.031327160 0 0)
(0.023919753 0 0)
(0.015277778 0 0)
(0.005401235 0 0)
)
;
}


-------------------------------------------------
---------after-------------------------------
------------------------------------------------

boundaryField
{
inlet
{
type fixedValue;
value nonuniform List<vector>
36
(
(0.00540123 0 0)
(0.00540123 0 0)
(0.0152778 0 0)
(0.0152778 0 0)
(0.0239198 0 0)
(0.0239198 0 0)
(0.0313272 0 0)
(0.0313272 0 0)
(0.0375 0 0)
(0.0375 0 0)
(0.0424383 0 0)
(0.0424383 0 0)
(0.046142 0 0)
(0.046142 0 0)
(0.0486111 0 0)
(0.0486111 0 0)
(0.0498457 0 0)
(0.0498457 0 0)
(0.0498457 0 0)
(0.0498457 0 0)
(0.0486111 0 0)
(0.0486111 0 0)
(0.046142 0 0)
(0.046142 0 0)
(0.0424383 0 0)
(0.0424383 0 0)
(0.0375 0 0)
(0.0375 0 0)
(0.0313272 0 0)
(0.0313272 0 0)
(0.0239198 0 0)
(0.0239198 0 0)
(0.0152778 0 0)
(0.0152778 0 0)
(0.00540123 0 0)
(0.00540123 0 0)
)
;
}

I need more precisely interpolated values. Can you advise me?

Thanks in advance.

in the sea of OpenFOAM.
asteria is offline   Reply With Quote

Old   December 20, 2007, 16:06
Default To All, I did mapFields to
  #16
Member
 
Doug Baldwin
Join Date: Mar 2009
Posts: 53
Rep Power: 8
gdbaldw is on a distinguished road
To All,

I did mapFields to an identical mesh, with the only difference being two wall boundaries of the source were mapped to a single wall (union of two source walls) in the target. Values in the boundary layer are way off, so I'm now running the solver on target mesh. Would be nice to do an exact copy of values, reordered for the target mesh, so that re-solving is unnecessary. Suggestions welcomed. -consistent flag in mapFields fails because number of boundaries differ.

Doug
gdbaldw is offline   Reply With Quote

Old   January 3, 2008, 05:18
Default Dear All, I have a question
  #17
Member
 
Tommaso Lucchini
Join Date: Mar 2009
Posts: 82
Rep Power: 8
lucchini is on a distinguished road
Dear All,

I have a question about the accuracy order of the meshToMesh::INTERPOLATE method.

As far as I know, it should be 2nd order accurate for internal cells and 1st order for boundary cells.

Is it that?

Thanks a lot, any suggestion will be really appreciated.

Regards

Tommaso
lucchini is offline   Reply With Quote

Old   May 4, 2010, 10:23
Default
  #18
Senior Member
 
Ivan Flaminio Cozza
Join Date: Mar 2009
Location: Torino, Piemonte, Italia
Posts: 207
Rep Power: 9
ivan_cozza is on a distinguished road
Send a message via MSN to ivan_cozza
Quote:
Originally Posted by imano View Post
Hi All!

In order to estimate the solution error on a coarse mesh,
I tried to map a solution on a finer mesh onto the orignal
coarse mesh with mapFileds utility.

But the mapped solution and the original solution are
seriously differ especially in a near-wall region when the normal
distances of the near-wall cell are the same in two meshs.

If we add meshToMesh::MAP option when we use a meshToMesh.interpolate
function in mapFields/MapConsistentVolFields.H or MapVolFields.H (i.e.
we use a direct mapping of nearest-cell values), we won't get severe
difference, but at the same time it won't be smooth.

In addition to that the default interpolation scheme used in the
mapFields (i.e. INTERPOLATION option) is an inverse distance
interpolation, so it seems to me that the mapped results may not have
the second order accuracy (i.e. not linear interpolation). This may
not be a problem when we use it in order to make initial guess on a
finer mesh, but it would not be acceptable in case of measuring a
differences between solutions on different meshes in detail.

So I also tried to use meshToMesh::CELL_POINT_INTERPOLATE which seems
to handle linear interpolation, but the serious inconsitency in the
near-wall region doesn't disappear.

Now I have two questions:

a) Can I consider that the CELL_POINT_INTERPOLATE options actually do
the linear interpolation?

b) Is there any good idea to avoid the inconsistency without using
the the direct mapping.


I attached a sample test case file about the mentioned above, please
try it if you have a spare time!

mapFieldsTest.tar.gz
Hi Foamers,
I'm interested in downloading the file mapFieldsTest.tar.gz that Imano posted sometimes ago, but it seems that the link point to nothing. Can someone upload the file?
Thanks, Ivan
ivan_cozza is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
MapFields only on internal fields cosimobianchini OpenFOAM Pre-Processing 1 June 23, 2015 09:49
MapFields does not work hartinger OpenFOAM Mesh Utilities 13 September 22, 2014 03:14
MapFields failure or incorrect mesh jvn OpenFOAM Pre-Processing 19 November 29, 2012 07:13
MapFields turbulent pipe flow anita OpenFOAM Pre-Processing 5 July 3, 2008 23:29
MapFields cpplabs OpenFOAM Running, Solving & CFD 3 February 17, 2008 06:08


All times are GMT -4. The time now is 09:25.