
[Sponsors] 
July 5, 2009, 12:05 
bulk temperature about a Area

#1 
New Member
Valentin Mayer
Join Date: Jul 2009
Posts: 5
Rep Power: 9 
Hello
I new in OpenFoam user and I try to get the bulk temperautre about a area. the theory: my problem tbulk = integration(U*T*dA) / integration(U*dA) the nummerical: I'm not really sure how to sovle this problem. Postprocessing or ? I think that you need a summation about the area,like: sum = sum + T(n)*U(n)*dy (Fortran 2D) How can i fixed this problem? Have somebody a idea? Thanks valentin 

July 6, 2009, 04:32 

#2 
Senior Member
Henrik Rusche
Join Date: Mar 2009
Location: Braunschweig, Niedersachsen, Germany
Posts: 277
Rep Power: 10 
Dear Valentin,
There are two issues. How to define the area and how to parallelise. I would also advise you to use the flux rather than the velocity since it is guaranteed to be conservative. Neglecting parallelisation issues and assuming that you want to work with patch (iP) the following will the job: Code:
heatFlux = sum(T.boundaryField()[iP]*phi.boundaryField()[iP])/sum(phi.boundaryField()[iP]); 

July 6, 2009, 12:30 

#3 
New Member
Valentin Mayer
Join Date: Jul 2009
Posts: 5
Rep Power: 9 
Hi Henrik,
sorry for this Question. But i'm not in used to work with openFoam. what means [ip] ? It is for direction, like [x]. I'm not sure if i get you wrong: Your equation mean: q=sum(t*flux)/sum(flux)=sum(t*rho*U)/sum((rho*U)) ? Is there no multiply wirh dy and dx? Thanks Valentin 

July 6, 2009, 14:51 

#4  
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 3,972
Rep Power: 41 
Quote:
Bernhard 

July 7, 2009, 08:34 

#5 
Senior Member
Henrik Rusche
Join Date: Mar 2009
Location: Braunschweig, Niedersachsen, Germany
Posts: 277
Rep Power: 10 
Dear Valentin,
thanks for your private message (in German). I hope you don't mind if I repeat what I understand is what you are trying to do. Valentin is seeking to evaluate the local Nusselt number and needs the bulk temperature to do so. The local Nusselt number would be per wall face (additional averaging may apply) and the bulk temperature is a function of the axial position in the pipe (xcoordinate in his case). The problem is now to evaluate the bulk temperature for a given axial position. Is this correct? Henrik 

July 7, 2009, 10:23 

#6 
New Member
Valentin Mayer
Join Date: Jul 2009
Posts: 5
Rep Power: 9 
Hello Hendriks,
that's right. I search for a summation (lilke (sum(sum( T.yz*U.yz*dy)dz)each Cells) about an area (yz).And every summation should go every cells in x> direction. Perhaps somebody has an idea. Thanks Valentin 

July 7, 2009, 11:22 

#7 
Senior Member
Henrik Rusche
Join Date: Mar 2009
Location: Braunschweig, Niedersachsen, Germany
Posts: 277
Rep Power: 10 
Dear Valentin,
Okay. I would try the following. Create a lookup table for T_bulk as a function of x. To do so, you need a function that maps x into an index. Code:
scalarField vol(nCellsx, 0.0); scalarField Tbulk(nCellsx, 0.0); forAll(T, cellI) { if ( inBulkRegion(mesh.C()[cellI]) ) { label index = floor(mesh.C()[cellI].x()/length*nCellsx); vol[index] += mesh.V()[cellI]; Tbulkl[index] += T[cellI]*mesh.V()[cellI]; } } Tbulk /= vol; This is by no means elegant, it will not parallelise easily and there are better ways of doing this. However, this will get you a long way. Henrik 

July 7, 2009, 12:19 

#8 
New Member
Valentin Mayer
Join Date: Jul 2009
Posts: 5
Rep Power: 9 
Hello Hendrik,
thanks a lot.Have a nice evening (in German). Bye Valentin 

August 13, 2011, 15:46 
bulk Temperature + cell selection

#10 
Senior Member
Nima Samkhaniani
Join Date: Sep 2009
Location: Tehran, Iran
Posts: 1,211
Blog Entries: 1
Rep Power: 17 
Code:
label patchii = mesh.boundaryMesh().findPatchID("fixedWall"); const Foam::fvsPatchField<Foam::Vector<double> > Cpatches = mesh.Cf().boundaryField()[patchii]; scalar nCellsx = Cpatches.size(); labelListList inBulkRegionList (nCellsx); forAll(Cpatches, cellj) { label nSelectedCell = 1; forAll(mesh.C(), celli) { if ( (Cpatches[cellj]).z() == (mesh.C()[celli]).z()) { inBulkRegionList[cellj].setSize(nSelectedCell,celli); nSelectedCell ++; } } } hi dear foamer i have a pipe! its axismyetric and it is 40*160! i want to have the cells in each cross section means the cells with the same highth! so i should have a list, this list has 160 sublist, each sublist contains the cell IDs of in each highth! so it should be 40! i wrote above code to make a list of list!!! it compiles well but the result is some how strange and it dose not return all cell selections in each height i expected it returns 40 cells in each height but you can see the results.can anybody tell me why? labelListList: 160 ( 19 // it should be 40 cells! ( 2 6 7 9 10 11 13 14 16 18 19 20 21 23 24 27 33 35 37 ) 18 ( 43 47 50 51 52 53 57 58 59 63 64 66 68 69 70 73 74 79 ) 5(84 85 87 117 119) 11 ( 123 125 129 130 136 139 140 141 143 149 152 ) 20 ( 160 161 166 167 169 170 172 173 176 177 178 180 181 182 185 190 195 196 197 199 ) 13 ( 200 201 205 209 210 217 221 222 224 229 232 235 238 ) 8(244 246 247 262 265 266 275 278) .... ) 

December 4, 2015, 14:51 
Bulk temperature

#11 
New Member
Mohammad Reza
Join Date: Sep 2015
Posts: 14
Rep Power: 3 
Hi nima sam and Bruno
I need the answer to this question, my case is an axisymetric heated pipe too, I need to calculate bulk temperature at each cross section ,tbulk = integration(U*T*dA) / integration(U*dA) to compute nusselt number.additionally it is needed for fully developed condition of T at the outlet of pipe!! any help or hint would be appreciated! Thanks in advance 

December 7, 2015, 03:59 

#12 
Senior Member
Nima Samkhaniani
Join Date: Sep 2009
Location: Tehran, Iran
Posts: 1,211
Blog Entries: 1
Rep Power: 17 
you should write some pieces of code to gather cells in each section and then return the value of them for calculation, above structure give you hints how to go forward.
__________________
Telegram channel (https://telegram.me/openfoam4Iranian) My Weblog (http://openfoam.blogfa.com/) Training Course on OpenFOAM at (http://www.isme.ir/) 

December 7, 2015, 14:18 

#13 
New Member
Mohammad Reza
Join Date: Sep 2015
Posts: 14
Rep Power: 3 
Dear Nima Sam
Thanks for your reply, your code was very inspiring for me but why it didn't get anticipated 2d array? maybe "size()" member function returns the number of neighbour cells for a cell but in this case we need to access patches which are normal to each wall patch.Is it the problem or anything else? bests, MohammadReza 

July 30, 2016, 16:59 

#14  
Member
Milad Setareh
Join Date: Oct 2012
Location: Tehran, Iran
Posts: 34
Rep Power: 6 
Quote:
the above code have been written by nimasam is very good but must be corrected till it works well. for reformation, if clause must be written as following: Quote:
Best regards, Milad 

October 14, 2016, 06:42 

#15 
New Member
Gurjeet Singh
Join Date: Oct 2016
Posts: 3
Rep Power: 2 
Hello all,
I am working on heat transfer analysis in rectangular duct using ANSYSFluent. for calculation of local nusselt number I need bulk fluid temperature. where, Tbulk = integration(U*T*dA) / integration(U*dA) I am able to get Tbulk. please help me to find that. 

October 14, 2016, 11:31 

#16  
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 3,972
Rep Power: 41 
Quote:
That is one of the reasons why one pays money for Fluent: you don't have to face sarcastic answers on the MessageBoard. Paid support people are polite
__________________
Note: I don't use "Friend"feature on this forum out of principle. Ah. And by the way: I'm not on Facebook either. So don't be offended if I don't accept your invitation/friend request 

October 14, 2016, 14:20 

#17 
New Member
Gurjeet Singh
Join Date: Oct 2016
Posts: 3
Rep Power: 2 
Dear Bernhard,
Thanks for your response. BUT need help to calculate integration of UTdA in Fluent. means how to calculate integral of product of more than one variable along the length. 

October 17, 2016, 11:32 

#18 
Assistant Moderator
Bernhard Gschaider
Join Date: Mar 2009
Posts: 3,972
Rep Power: 41 
You're in an OpenFOAMforum. People here usually don't know Fluent. And if they do they won't admit it. Ask in the FluentForum
__________________
Note: I don't use "Friend"feature on this forum out of principle. Ah. And by the way: I'm not on Facebook either. So don't be offended if I don't accept your invitation/friend request 

November 3, 2016, 13:50 

#19  
Member
Mirage
Join Date: Jul 2012
Posts: 38
Rep Power: 6 
Quote:
I would like to use the code to compute my Tbulk. But It is for me not clear, how does this code compute Tbulk and Where should I write the code? Thanks for your help 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
UDF or any approach for Bulk Temperature calculation  vemps  FLUENT  0  May 1, 2009 01:09 
how to find bulk temperature plot and results in fluent  cadcamvijay  Main CFD Forum  2  March 21, 2009 01:36 
CFX Solver Memory Error  mike  CFX  1  March 19, 2008 08:22 
Bulk temperature for HTC extimation  Italy  CFX  4  July 12, 2007 00:05 
bulk temperature calculation  Yogesh  FLUENT  0  February 18, 2005 16:37 