CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM Running, Solving & CFD

Car aerodynamics

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes

Reply
 
LinkBack Thread Tools Display Modes
Old   January 31, 2008, 13:11
Default Hallo, I'm going to validate
  #1
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
Hallo,
I'm going to validate OpenFOAM with differents turbolence models for calculation of aerodynamic coefficients of formula cars. Before starting to work with a complete car, I want validate a model of bluff body with car shape, somethin as the Ahmed model. Unfortunately I don't have aerodynamic coefficients of models like this! Someone has a geometry and the relative experimental lift and drag coefficients to make this comparison?
Furthermore because I have experience of this kind of simulation with another commercial sotware but not with OpenFLOW, if someone is working with car aerodynamics, can give me information about the turbolence model is using please?
morfeus80 is offline   Reply With Quote

Old   January 31, 2008, 14:38
Default Here http://cfd.mace.mancheste
  #2
Member
 
Michele Vascellari
Join Date: Mar 2009
Posts: 70
Rep Power: 8
mighelone is on a distinguished road
Here http://cfd.mace.manchester.ac.uk/ercoftac/ you can find the experimental data relatives to Ahmed body and other test cases.

Registration is required to download data!

Michele
joy2000 likes this.
mighelone is offline   Reply With Quote

Old   January 31, 2008, 17:13
Default Thanks, that website is very i
  #3
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
Thanks, that website is very interesting, but I didn't find what I need because there are pressure data and velocity fields, but nothing about lift and drag. Instead these are the parameters I need to validate my model!
morfeus80 is offline   Reply With Quote

Old   January 31, 2008, 18:16
Default Hi Mattia, may I ask what s
  #4
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Hi Mattia,

may I ask what software you intend to use for meshing?
bastil is offline   Reply With Quote

Old   February 1, 2008, 07:25
Default In the past I used Ansa and Tg
  #5
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
In the past I used Ansa and Tgrid, now I have to decide. I thinked to can use the openFoam preprocessor, but it doesn't look very developed...
morfeus80 is offline   Reply With Quote

Old   February 2, 2008, 07:47
Default The OpenFoam preprocessor "blo
  #6
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
The OpenFoam preprocessor "blockMesh" is not suited for handling theses complex geometries. I think if you want to use open source you can try to use one of the tet-meshers out there and use polyDualMesh afterwards to convert to polyhedral. However, you nee more or less clean CAD data (geometries) or a clean surface mesh for that, do you have that? Hex-dominant meshes are better than polys and I am still seeking some mesher for that. Tell me if you have one. I am also seeking for some surface mesh repair without havin ggeometry.

Regards
bastil is offline   Reply With Quote

Old   February 3, 2008, 10:42
Default I have the complete geometry o
  #7
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
I have the complete geometry of the car, but I need the software to make the surface and volume mesh. According to your opinion what are the best open source software to make mashes on very complex geometries?
morfeus80 is offline   Reply With Quote

Old   February 3, 2008, 11:51
Default Regarding mesher. I needed a
  #8
Member
 
Doug Baldwin
Join Date: Mar 2009
Posts: 53
Rep Power: 8
gdbaldw is on a distinguished road
Regarding mesher. I needed a quad surface with hex grid, first cell less than 1000 aspect ratio and acceptable skew, first cell at y+ of about 2 to 5. I patched together a script for Blender to specify just this kind of geometry, which exports to Calculix for building a grid, then exports to OpenFOAM. Works great, and I posted the script elsewhere in this forum. In my opinion, it would be an ideal free and open source tool for this problem. I used it for aero analysis of a fuselage. You'd need to be proficient in Blender from blender.org, and also learn Calculix, neither are insurmountable. If interested, I'd suggest finding an online tutorial for "Blender subsurf" and mastering this modelling technique (using quads only), then download Calculix and learn how to generate and export a simple geometry to OpenFOAM using the Calculix tutorial. After that, you are good to go. Download the Blender script I had posted and start generating 3-D compound/convex hex grids in a matter of hours or a few days depending on the level of complexity. Ahmed would take less than a day, but you'd need to invest many days in learning the technique.

By the way, there is another thread in this forum regarding attempts to model Ahmed. As I recall from the other thread there already exists OpenFOAM models of Ahmed. I'd be interested in lift/drag results you generate.

Doug
gdbaldw is offline   Reply With Quote

Old   February 3, 2008, 18:41
Default Mattia, is the geometry cle
  #9
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Mattia,

is the geometry clean or not (holes, overlappings, small faces,...)?
If your geometry is more or less clean you could try using netgen or salome to create surface and volume meshes (tets). Afterwards use dualPolyMesh to convert to poly if desired.

Concerning the blender method I think it has the drawback that you can not import existing CAD data to blender, can you? Nevertheless, I do not think that this will give you meshes for really complex car geometries with all features and maybe underhood. How compplex is your geometry?
bastil is offline   Reply With Quote

Old   February 4, 2008, 00:17
Default True, the Blender method is be
  #10
Member
 
Doug Baldwin
Join Date: Mar 2009
Posts: 53
Rep Power: 8
gdbaldw is on a distinguished road
True, the Blender method is best when new geometry is created. Ahmed could be quickly created in Blender. In theory it can also work with STL, since Blender can import STL format. I haven't needed to take that step.

Doug
gdbaldw is offline   Reply With Quote

Old   February 4, 2008, 04:50
Default Dear Mattia, are you workin
  #11
Member
 
Tommaso Lucchini
Join Date: Mar 2009
Posts: 82
Rep Power: 8
lucchini is on a distinguished road
Dear Mattia,

are you working with OpenFOAM for car aerodynamics in Italy? Could you possibly contact me by e-mail ( tommaso . lucchini @ polimi . it)?

Thanks a lot, bye

Tommaso
lucchini is offline   Reply With Quote

Old   February 4, 2008, 17:55
Default I Think blender in combination
  #12
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
I Think blender in combination with STL is possible if the stl is more or less clean. However stl from CAD packages normally are not. I hav a lot of dirty stl files I want to mesh with open source and so far I have no solution for this with accepable efford.

Regards
bastil is offline   Reply With Quote

Old   February 4, 2008, 22:58
Default BastiL, If you are up to do
  #13
Member
 
Doug Baldwin
Join Date: Mar 2009
Posts: 53
Rep Power: 8
gdbaldw is on a distinguished road
BastiL,

If you are up to doing some modest Python coding, Blender with STL could work. I haven't the need, else I'd look into it. For my needs, I coded a Python script to create a Calculix input file from multiple subsurf manifolds extending from the body to the far field. In order to adapt this script for STL, the first subsurf manifold would closely follow the STL geometry, and become the template for projecting the STL faces onto each subsequent manifold. Then, in Calculix, each STL triangle would be subdivided into three quads before generating a hex grid for export to OpenFOAM. The only significant additional coding needed is to map STL vertices to the nearest manifold subsurf face.

Doug
gdbaldw is offline   Reply With Quote

Old   February 4, 2008, 23:05
Default BastiL, By the way, Blender
  #14
Member
 
Doug Baldwin
Join Date: Mar 2009
Posts: 53
Rep Power: 8
gdbaldw is on a distinguished road
BastiL,

By the way, Blender has a new feature that could help with cleaning bad STL. While in edit mode, you can Select "Non-Manifold" edges, which I have found selects only those edges that are not connected to exactly two faces.

Doug
gdbaldw is offline   Reply With Quote

Old   February 5, 2008, 05:07
Default BastiL, my geometry is very c
  #15
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
BastiL,
my geometry is very complex and I'll have to clean it.
morfeus80 is offline   Reply With Quote

Old   February 5, 2008, 05:13
Default Ciao Mattia, I can suggest
  #16
Member
 
Luca Gasparini
Join Date: Mar 2009
Location: Italy
Posts: 37
Rep Power: 8
luca_g is on a distinguished road
Ciao Mattia,

I can suggest you the following links (among many others you will find on the web) to papers related to computations on the Ahmed body. They all include pictures taken from the original Ahmed's SAE paper (which I don't have) reporting the experimental drag figures. No measure of downforce however, as far as I know, and it is anyway very low.

http://tmdb.ws.tn.tudelft.nl/worksho...B2000_NNFM.pdf

http://www.edpsciences.org/articlesp.../gillieron.pdf

http://www.imft.fr/GDR2502/journee24...Guilmineau.pdf

About the experimental drag figure I'm quite sure they are either "windtunnel corrected" values or the measures where done in a large tunnel with very low blockage and at 60m/s. On the contrary, the subsequent measurements (see first paper) where done on a small tunnel with 4% blockage at 40m/s and no drag figures are reported.

So it seems to me that to come closer to the experimental drag a large computational domain must be used, whereas a confined test section should be more appropriate to compare to the velocity profiles of the second experiment.

Luca
luca_g is offline   Reply With Quote

Old   February 5, 2008, 05:59
Default Luca, Thanks for the advice,
  #17
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
Luca,
Thanks for the advice, I'll start to work at this and as soon as I'll have some results, I'll give you.

Ciao!
morfeus80 is offline   Reply With Quote

Old   February 15, 2008, 18:30
Default Mattia, are there some news
  #18
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Mattia,

are there some news concerning mesh tools? I am srill seeking for well suited open source tools and would be happy about hints.

BastiL
bastil is offline   Reply With Quote

Old   February 16, 2008, 09:22
Default BastiL, I have read this week
  #19
New Member
 
Mattia
Join Date: Mar 2009
Posts: 26
Rep Power: 8
morfeus80 is on a distinguished road
BastiL,
I have read this week the topic about Mesh3D, it's open-source and looks interesting. But I hadn't time to test it so far.
In this days I'm working with a mesh I alredy had an I'm testing several turbulence models and solvers. As soon as I'll reach good results, I'll start to work on the pre an post processors.
morfeus80 is offline   Reply With Quote

Old   February 17, 2008, 06:52
Default Mattia, i have seen that, t
  #20
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Mattia,

i have seen that, too. Looks interesting but has two drawbacks:
* Windows only
*32 Bit only

I Think this is not the way to go for large aerodynamic meshes.
I am also interested in your solver experiences. Is it possible to share them? What solvers? SimpleFoam?
bastil is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Aerodynamics vengi FLUENT 5 October 25, 2011 10:43
Aerodynamics Bonny Jacob Zachariah Phoenics 3 February 10, 2009 05:43
CFD in aerodynamics Ujjwal Bhaskar FLUENT 1 December 26, 2007 11:29
Use of Pro-Am in aerodynamics Javidan Ahmad CD-adapco 8 December 3, 2004 00:27
unsteady aerodynamics R.KRISHNAMURTHY Main CFD Forum 1 December 6, 2000 02:17


All times are GMT -4. The time now is 17:58.