
[Sponsors] 
April 23, 2008, 06:48 
Dear Foamers,
i would like

#1 
Member
Christian Winkler
Join Date: Mar 2009
Location: Mannheim, Germany
Posts: 63
Rep Power: 9 
Dear Foamers,
i would like to calculate a growing bubble with interFoam. So far nothing spectacular. I would like to let the bubble grow simply by adding a mass source term within the bubble. In principle that would be done by adding a source term to the continuity equation ddt(rho) + div(rho,U)= mass_source * gamma Unfortunatly the continuity is not solved that way in interFoam. Is there anyone out there who has done something like this (adding mass sources to any solver?), or anybody who could give me a good hint? Thanks in advance best regards Christian 

April 23, 2008, 11:54 
Dear Christian,
The continu

#2 
Member
Patricio Bohorquez
Join Date: Mar 2009
Location: Jaén, Spain
Posts: 94
Rep Power: 9 
Dear Christian,
The continuity equation used by interFoam, Eq. (4.3) in Rusche (2002), is div(U) = 0. We do not use div(rho)+div(rho,U) = 0 because the freesurface is expected to be a thin interface. Thus, the equation you want to solve now reads div(U) = mass_source*gamma/rho The PISOLoop should then be reformulated according to the equation shown above. Have a look, for instance, to Rusche (2002, Section 4.2.4) and Jasak (2006, Section 10.4.1): "A revised formulation of the pressure equation via a Schur's complement yields" ... fvScalarMatrix pdEqn( fvm::laplacian(rUAf, pd) == fvc::div(phi)  mass_source*gamma/rho ); Be careful with the numerical treatment of the source term on the r.h.s. All the best, Patricio Rusche, H., 2002. Computational fluid dynamics of dispersed twophase flows at high phase fractions. Ph.D. thesis, Imperial College, University of London. Jasak, H., 2006. Numerical solution algorithms for compressible flows: Lecture Notes. University of Zagreb, Croatia. 

April 25, 2008, 02:06 
Dear Patricio,
thanks for p

#3 
Member
Christian Winkler
Join Date: Mar 2009
Location: Mannheim, Germany
Posts: 63
Rep Power: 9 
Dear Patricio,
thanks for pointing me into the right direction. I allready thought that i would have to modify the pressure equation. This is done for now and works. The problem this causes is that gamma stays conservative. That is because gamma is calculated based on the face flux from last timestep and therefore changes over time. What follows is that the mass within the system stays constant which it should not because there is a mass source term. If i use a mass sink i can even cause gamma to grow greater than one ;) Therefore i have to add the mass source to the gamma equation as well. When i have found a convenient way to do this, i will post the solution. Kind regards Christian 

April 25, 2008, 11:55 
I don't know if the info that

#4 
Member
Patricio Bohorquez
Join Date: Mar 2009
Location: Jaén, Spain
Posts: 94
Rep Power: 9 
I don't know if the info that follows will help or work?
I agree with you. We are adding mass corresponding to the gammaphase, so the mass source should be added not only to the mixture continuity equation but to the gammaphase continuity equation by itself. In this line the gammaEqn.H file is to be updated. Presently, the key point is MULES MULES::explicitSolve01(gamma, phi, phiGamma); which employs the explicit solver and ensures a bounded solution in the range [0,1]. So, how to add the source term and conserve the bounded solution? If the source could be written as a divergence, it would be quite easy, because the gamma equation would read ddt(gamma) + div(phi, gamma) + div(phirg, gamma) + div(source/gamma, gamma) == 0 and therefore the fluxes used by MULES could be readily modified to include the gammasource. Otherwise, we can use the alternative MULES::explicitSolve01 ( volScalarField& psi, const surfaceScalarField& phi, surfaceScalarField& phiPsi, const SpType& Sp, const SuType& Su ); which accepts source terms in the gamma equation. Hope your code works. Patricio 

April 29, 2008, 09:28 
Hi all,
i have a problem;i ne

#5 
Member
davey david
Join Date: Mar 2009
Posts: 54
Rep Power: 9 
Hi all,
i have a problem;i need to add the laplace equation to my solver because i need to solve for electric potential(fields) in particular regions of my mesh.i tried doing it as before(i.e like adding a source term to a code)but i am getting error messages all the while.can anyone please help out here? thanks in advance davey 

June 24, 2009, 11:57 

#6 
Senior Member
isabel
Join Date: Apr 2009
Location: Spain
Posts: 171
Rep Power: 9 
Dear Pbohorquez,
Thanks for your explanation about how to add a source to the gamma equation. The problem is that I don´t understand very well. I am working with interFoam solver. In gammaEqn.H I want to add a source. I must modify the line: MULES::explicitSolve(gamma,phi,phiGamma,1,0) I don´t know how to solve the equation: ddt(gamma) + div(phi, gamma) == user_source 

July 16, 2009, 06:59 

#7 
Senior Member
isabel
Join Date: Apr 2009
Location: Spain
Posts: 171
Rep Power: 9 
There is other way to add a source to the gamma equation: in the solver interPhaseChangeFoam, the gammaEqn.H is:
volScalarField Sp ( IOobject ( "Sp", runTime.timeName(), mesh ), vDotvAlphal  vDotcAlphal ); volScalarField Su ( IOobject ( "Su", runTime.timeName(), mesh ), divU*gamma + vDotcAlphal ); MULES::implicitSolve(oneField(), gamma, phi, phiGamma, Sp, Su, 1, 0); where: gamma is the actual value to be solved phi is the normal convective flux phiGamma = gamma*(1gamma)*U Sp is the implicit source term Su is the divergence term My doubt is: What divergence term Su means? Divergence of what? 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
InterFoam mass conservation question  msrinath80  OpenFOAM Running, Solving & CFD  5  December 9, 2013 02:19 
mass source and mass sink for multicomponent  frank  CFX  0  May 14, 2008 11:55 
Mass sink and mass source in eulerTwoPhase application  newbee  OpenFOAM Running, Solving & CFD  3  July 9, 2006 07:15 
about mass source for species  lu  FLUENT  5  September 25, 2003 22:29 
help on UDF mass source  shao1  FLUENT  2  July 11, 2002 20:36 