Hi all, I would like to conve
I would like to convert into Foam a pro-Star4 format mesh. I have done this procedure many times without problems, the peculiarity is that this time the mesh is composed by polyhedral elements. Being a test the chosen mesh is very simple: a single cylinder with inlet, outlet and wall.
I found some errors in importing the boundary conditions set up with pro-Star4. The geometry is exactly converted but boundary polymesh fails to be created.
Two types of error come out:
There are 2554 faces to be patched and 237 specified - collect missed boundaries to final patch
meshReader::createPolyBoundary(): Problem with face: 6(11916 17960 17961 17962 17963 11917)
Probably trying to define a boundary face on a previously matched internal face.
Internal face: 6(11916 17960 17961 17962 17963 11917)
meshReader::createPolyBoundary() : problem with face 1278: addressed 1 times (should be 2!). Face: 6(2011 2012 2013 2014 2015 2016)
Is there anyone that already found this errors? How did you solve it?
Thanks a lot for the help
Hi Cosimo, Assuming that yo
Assuming that you are using the last patch posted here (13 Nov 2006), the following mini-patch should help solve the problem. The culprit is the incorrect lookup in "mapToFoamCellId_" (typical cut/paste error) that is around line 461 of starMeshReader.C
else if (shapeId == 255)
// poly cell - create cell faces directly
label nFaces = starLabels - 1;
// record original cell number and lookup
origCellId_[cellI] = starCellId;
mapToFoamCellId_[starCellId] = cellI;
The version that you have likely has the obviously wrong
mapToFoamCellId_[starCellId] = starCellId;
After OpenFOAM v1.4 is released, I'll be able to post a more recent version that also handles defined, but unused vertices and various other improvements.
Thank you very much Mark for t
Thank you very much Mark for the quick and effective reply. Following your suggestion, everything works now.
Thanks a lot again
|All times are GMT -4. The time now is 20:20.|