
[Sponsors] 
May 19, 2005, 12:43 
Hi,
I'm trying to model air f

#1 
Member
David Segersson
Join Date: Mar 2009
Posts: 39
Rep Power: 9 
Hi,
I'm trying to model air flow through vegetation and need to add a negative source term to the momentum equation in simpleFoam. I would appreciate some advice to get this right (I'm quite new to OpenFOAM...). For the different directions the source term is: Sx = 0.5*rho*Cd*abs(u)*u Sy = 0.5*rho*Cd*abs(v)*v Sz = ... ,where Cd is a constant. My questions are: 1. After I have created a volScalarField for Cd, how can I express the term in OpenFOAM in a nice way? ( S = 0.5*rho*Cd*U&U gives me the wrong sign I guess...) 3. Is it correct to insert the source term in simpleFoam.C as: solve(UEqn() == S fvc::grad(p)); Do I have to include the source term anywhere else in the SIMPLE algorithm? 3. If I want the term to be explicit, are there any advantage in using the SuSp(..,..) function? Regards David 

May 19, 2005, 12:53 
Basically you are adding a dra

#2 
Senior Member
Join Date: Mar 2009
Posts: 854
Rep Power: 14 
Basically you are adding a drag term in which case you should make it implicit using fvm::Sp. Is the drag coefficient a scalar or should it be tensorial to take into account anisotropy? If scalar I think your source term should be
fvm::Sp(0.5*rho*Cd*mag(U), U) and remember to include it in the momentum equation construction not in solve(UEqn() == S fvc::grad(p)); otherwise the pressure equation will not "see" the drag term at all. 

May 20, 2005, 11:17 
hi,
I added the energy equati

#3 
Guest
Posts: n/a

hi,
I added the energy equation in icoFoam, this equation depends, obviously, the rates of flow: u, v and w. my questions are: 1 how to add a source term in the momentum equation only in z direction? 2 this source term does not depend on velocity but it depends on the temperature: g*beta*(TTref) (approximation of Boussinesq), icoFoam can it solve equation(equation of movement coupled with the equation of energy)? thank you in advance for your assistance zohra 

May 20, 2005, 11:31 
Create g as a dimensionedVecto

#4 
Senior Member
Join Date: Mar 2009
Posts: 854
Rep Power: 14 
Create g as a dimensionedVector then g*beta*(TTref) will be a volVectorField containing components only in the gdirection and this can be added as a source term to the momentum equation.
You will have to think carefully about the pressure boundary conditions because zerogradient on walls will no longer be appropriate. Alternatively you can use the approach in the buoyantflow codes I have already written in which a "dynamicpressure" pd is used which is p  rho*(g&h) which avoids some of the issues to do with the pressure boundary conditions as well as potential solution staggering that can occur on collocated meshes. 

May 20, 2005, 13:23 
hi,
I will apply what you h

#5 
Guest
Posts: n/a

hi,
I will apply what you have suggest me. thank you 

March 3, 2006, 00:06 
Dear chafi fatima zohra:
I

#6 
Senior Member
Guoxiang
Join Date: Mar 2009
Posts: 109
Rep Power: 9 
Dear chafi fatima zohra:
I have the same question about how to add the source term in cavity case of icoFoam. Could you please give some advice please? Thanks a lot. Best wishes, Guoxiang 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Adding source term to u eq  roberthino  OpenFOAM Running, Solving & CFD  23  September 22, 2014 10:24 
Adding a volumetric source term in femlab  BS  Main CFD Forum  1  December 28, 2006 21:26 
Question on adding source to momentum  CFDtoy  Main CFD Forum  0  May 2, 2006 11:51 
Adding a source term to continuity eqn(UDF)  Sebeci  FLUENT  0  April 20, 2003 03:12 
adding source term confusion  tedmcc  CFX  4  September 27, 2001 05:05 