CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM Running, Solving & CFD

This result reasonable help me

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   August 15, 2005, 23:55
Default I compute the motion of threee
  #1
Member
 
zoujianfeng
Join Date: Mar 2009
Location: Hangzhou, China
Posts: 30
Rep Power: 7
zou_mo is on a distinguished road
Send a message via MSN to zou_mo
I compute the motion of threee bubbles with interFoam. The cGamma is 1.5 for 3D case. From the following jpg figure, we can find some dirty fragments. These fragments may be introduced by the algorithm embedded in interFoam? I have not got idea to solve this problem. Can anyone give me any advie?

time=0.1s and time=.35s:






Thanks.
zou_mo is offline   Reply With Quote

Old   August 16, 2005, 00:05
Default The result for the single mode
  #2
Member
 
zoujianfeng
Join Date: Mar 2009
Location: Hangzhou, China
Posts: 30
Rep Power: 7
zou_mo is on a distinguished road
Send a message via MSN to zou_mo
The result for the single mode RT instability is as follows:



The interface is beautiful, yet.
zou_mo is offline   Reply With Quote

Old   August 16, 2005, 04:22
Default It is not clear that those fra
  #3
Senior Member
 
Join Date: Mar 2009
Posts: 854
Rep Power: 12
henry is on a distinguished road
It is not clear that those fragments are incorrect, they may be a natural consequence of a break-up process caused by the up-draft in the wake of the middle bubble but they may also be numerical as you suggest. What schemes are you using for the terms of the U an gamma equations?
henry is offline   Reply With Quote

Old   August 16, 2005, 04:36
Default The scheme list: ddtSchemes
  #4
Member
 
zoujianfeng
Join Date: Mar 2009
Location: Hangzhou, China
Posts: 30
Rep Power: 7
zou_mo is on a distinguished road
Send a message via MSN to zou_mo
The scheme list:
ddtSchemes
{
// Default scheme
default Euler;
}

// Gradient discretisation schemes
gradSchemes
{
// Default gradient scheme
default Gauss linear;
grad(U) Gauss linear;
grad(gamma) Gauss linear;
}

// Convection discretisation schemes
divSchemes
{
div(rho*phi,U) Gauss upwind;
div(phi,gamma) Gauss Gamma201 0.2;
div(phirb,gamma) Gauss Gamma201 1;
}

// Laplacian discretisation schemes
laplacianSchemes
{
// Default scheme
default Gauss linear corrected;
}

// Interpolation schemes
interpolationSchemes
{
// Default scheme
default linear;
}

// Surface normal gradient schemes
snGradSchemes
{
// Default scheme
default corrected;
}

// Calculation of flux
fluxRequired
{
// Create storage for flux for all solved variables?
default no;
pd;
pcorr;
gamma;
}

I will try to do some tests with different schemes.

Thanks.
zou_mo is offline   Reply With Quote

Old   August 16, 2005, 04:49
Default I don't think your choice of s
  #5
Senior Member
 
Join Date: Mar 2009
Posts: 854
Rep Power: 12
henry is on a distinguished road
I don't think your choice of schemes are appropriate for thise case, in particular upwind on U will cause a lot of unnecessary damping and given that your case is low Re you could probably use linear of if that gives trouble Gamma2V 1. However, this will not affect the fragmentation of the interface, to see if this is real or numerical try with

div(phi,gamma) Gauss Gamma01 1;
div(phirb,gamma) Gauss Gamma01 1;
henry is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Fluent Result Mustafa Ayad FLUENT 8 June 10, 2009 07:58
VWT Unable to get reasonable results dyroffk OpenFOAM Running, Solving & CFD 17 February 19, 2009 02:02
reasonable mixing rate for C2H6 Oxygen mixture N. Schiepel CFX 0 September 12, 2008 04:57
reasonable result for air flow in city buildings? George FLUENT 0 August 21, 2006 20:36
Cannot get the right result Eric Main CFD Forum 1 September 30, 2005 14:08


All times are GMT -4. The time now is 08:14.