CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM Running, Solving & CFD

Spalart-Allmaras model, boundary and initial conditions

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree4Likes
  • 2 Post By Simon Lapointe
  • 1 Post By vinz
  • 1 Post By Simon Lapointe

Reply
 
LinkBack Thread Tools Display Modes
Old   December 15, 2009, 09:48
Default Spalart-Allmaras model, boundary and initial conditions
  #1
Senior Member
 
Vincent RIVOLA
Join Date: Mar 2009
Location: France
Posts: 277
Rep Power: 9
vinz is on a distinguished road
Dear OpenFoamers,

I have few questions about the Spalart-Allmaras model in OpenFOAM.
I found this web page dealing with the different versions of SA model: http://turbmodels.larc.nasa.gov/spalart.html
I'd like to know which one is implemented in OpenFOAM.

I also have questions about the initial values for nut and nutilda. I have been surprised to see that values of 0.14 are imposed for nut and nutilda in the airfoild2D tutorial. Those values look pretty high to me but I may be missing something here.

I would like to know how should I choose my initial far field values of nut and nutilda for a flow around an airfoil at 50m/s for example. Can someone help me with that please?

Any information on the model and/or the boundary conditions and initial conditions would be very welcome.

Regards,

Vincent
vinz is offline   Reply With Quote

Old   December 15, 2009, 10:41
Default
  #2
Member
 
Simon Lapointe
Join Date: May 2009
Location: Québec, Qc, Canada
Posts: 33
Rep Power: 8
Simon Lapointe is on a distinguished road
Hi Vincent,

Unless there has been a recent change, the version of the Spalart-Allmaras RANS model in OpenFOAM is the one with fv3 Term (SA-fv3). This version is not recommended but is said to be more stable, especially in complex geometries. If you want to use the "standard" version, it is easy to implement.

Concerning the farfield values, it depends of your problem. In the case of an external flow around an airfoil, you might want to use rather small values of nut (maybe a viscosity ratio of 0.1 or smaller). For nuTilda, Spalart recommends using a farfield value of about 3*nut.

Hope this helps.
alpemre and mechy like this.
Simon Lapointe is offline   Reply With Quote

Old   December 15, 2009, 11:01
Default
  #3
Senior Member
 
Vincent RIVOLA
Join Date: Mar 2009
Location: France
Posts: 277
Rep Power: 9
vinz is on a distinguished road
Hi Simon,

and thank you for your fast reply. You advise a viscosity ratio of 0.1, that means I should use nut around 1e-6 if I use a nu value of 1e-5, right?
And then a nuTilda of 3e-6? does it look right for you?

Do you happen to know why the values of nut and nuTilda have been set so high (0.14) in the airfoil2D tutorial? Unless we should impose the viscosity ratio instead of the variable value itself inside nut and nuTilda initial dict?

Thanks again.

Vincent
tareqkh likes this.
vinz is offline   Reply With Quote

Old   December 15, 2009, 11:32
Default
  #4
Member
 
Simon Lapointe
Join Date: May 2009
Location: Québec, Qc, Canada
Posts: 33
Rep Power: 8
Simon Lapointe is on a distinguished road
Yes those values seem right. You might also want to try different values to clarify the influence of the farfield values on your solution. In the case of an external flow around an airfoil, I did not see major differences when the upstream boundary is far from the airfoil.

I'm sorry but I can't really help you with the airfoil2D tutorial. I'm pretty sure these are nut and nuTilda values (especially since the dimensions are specified) and not viscosity ratios.
Simon Lapointe is offline   Reply With Quote

Old   July 7, 2010, 08:36
Default
  #5
New Member
 
Sofia
Join Date: May 2010
Location: Toulouse, France
Posts: 14
Rep Power: 7
Sofia is on a distinguished road
Hi,

Do you know the difference between nu and nut in the SA turbulence model,

thank you

Sofia
Sofia is offline   Reply With Quote

Old   July 7, 2010, 08:56
Default
  #6
Member
 
Simon Lapointe
Join Date: May 2009
Location: Québec, Qc, Canada
Posts: 33
Rep Power: 8
Simon Lapointe is on a distinguished road
Hi Sofia,

nu is the kinematic viscosity, a property of the fluid. nut is the turbulent kinematic viscosity, calculated by the turbulence model.

In the Spalart-Allmaras model, nut is calculated by the means of a transport equation for nuTilda (modified turbulent kinematic viscosity). nut is obtained by multiplying the transported variable nuTilda by a function (fv1).
manojkv likes this.
Simon Lapointe is offline   Reply With Quote

Old   July 9, 2010, 08:11
Default
  #7
New Member
 
Sofia
Join Date: May 2010
Location: Toulouse, France
Posts: 14
Rep Power: 7
Sofia is on a distinguished road
Thank you Simon,

I choose nut=nu and it works well...
Sofia is offline   Reply With Quote

Old   July 20, 2015, 04:57
Default
  #8
Member
 
Ashwani
Join Date: Sep 2013
Location: Hyderabad
Posts: 86
Rep Power: 3
AshwaniAssam is on a distinguished road
The SA model in openFOAM has been updated with the standard Spalart-Allmaras Model.

link1 link2
AshwaniAssam is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Superlinear speedup in OpenFOAM 13 msrinath80 OpenFOAM Running, Solving & CFD 18 March 3, 2015 06:36
Wind turbine simulation Saturn CFX 34 October 16, 2014 05:27
Low Mach number Compressible jet flow using LES ankgupta8um OpenFOAM Running, Solving & CFD 7 January 15, 2011 14:38
RPM in Wind Turbine Pankaj CFX 9 November 23, 2009 05:05
Convective Heat Transfer - Heat Exchanger Mark CFX 6 November 15, 2004 16:55


All times are GMT -4. The time now is 18:23.