Local time step
I want to use local time steps to converge to steady state quickly. I have fixed the maxCo and want to calculate deltaT for each cell (local time step). My Openfoam rho (for e.g.) equation reads :
rho = rho  runTime.deltaT()*fvc::div(phi); ...... I checked setDelta.H, compressibleCourantNo.H which tells runTime.deltaT() as a scalar. But I want a runtime.deltaT() as volScalarField which has delta time defined for each cell. Can anyone help me in this regard :confused: 
The runTime scalar is used in the fvc and fvm namespaces in the discretization process. If you want to have any of these functions work with the local time, then you are looking at a complex problem. If, on the other hand, you just want to store a "local time" field that you use independently, that would be much easier. How do you plan to use the local time?

" If, on the other hand, you just want to store a "local time" field that you use independently, that would be much easier"
Exactly the second one. A false time field just to update rho,rhoU and rhoE For e.g. rho = rho  runTime.deltaT()*fvc::div(phi) rhoU = rhoU  ... rhoE = rhoE  ... runTime.deltaT() is very local (or which only plays around setDelta.H, readTimecontrols.H and compressibleCourantNumber.H) and nothing to do with ddt schemes I specify. (whatever ddtscheme in the fvSchemesDict) & Hopefully, I didn't confuse you Thanks, hari 
Take a look at the SLTSDdtScheme in $(FOAM_SRC)/finiteVolume/ddtSchemes/SLTSDdtScheme

Also, the just released new version of OpenFoam uses a local time step for their new VOF solver:
http://www.openfoam.com/version2.0.0/steadyvof.php You might want to have a look at that. 
Dear all,
( Please check the previous posts in this thread to have an idea) I have slightly modified the inviscid solver rhoCentralFoam in order to improve the acceleration to steady state using local time step without touching any other part (e.g. reconstruct().  flux calculations). And it seems working for my case. If anyone have a word/doubt in my modification please post it. //////////Local time step  false time step forAll (mesh.C(),i) { cell faces = mesh.cells()[i]; denom = 0.0; forAll (faces,j) { denom = denom + ( (U[i] & mesh.Sf()[j]) + c[i]*mesh.magSf()[j] ); } falseTime[i] = maxCo * mesh.V()[i] / denom; } //////// Conservation equations //  Solve density rho = rho  falseTime*fvc::div(phi); //  Solve momentum rhoU = rhoU  falseTime*fvc::div(phiUp); //  Solve energy rhoE = rhoE  falseTime*fvc::div(phiEp); 
Has anyone else done this? I'm really interested in speeding up my rhoCentralFoam simulations but am having some trouble implementing it. I'd really appreciate the help anyone else can give!
Thanks, Eric 
Dear all
I need a reference which describes by more details the new localtime stepping (LTS) approach applied in VOF in openfoam. Thanks 
Quote:
Dear Friend There is one question: the falsetime that you are calculating is the local deltaT. so its changing from cell to cell. so its almost the same as the local euler or coeuler scheme in openfoam? secondly this scheme is not giving unsteady result. just the final result could be correct? How can u access the simulationtime? how you will control writting the variables according the controldict writecontrol ( considering that u have local time ) Best Mahdi 
All times are GMT 4. The time now is 23:06. 