CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM

help: wave making resistance on submerged sphere

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree3Likes
  • 1 Post By nimasam
  • 2 Post By vonboett

Reply
 
LinkBack Thread Tools Display Modes
Old   June 9, 2012, 07:25
Default help: wave making resistance on submerged sphere
  #1
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
Hello all
I'm trying to simulate a 3D free surface flow around a sphere. because its first time that i work on free surface, please help me about that problem!

these are my questions:
1. what's the domain(height,weight,width as a function of sphere diameter) in this case
2. Boundary conditions of domain
3. turbulence properties
4. in which reynolds number we have to use turbulent and which one we have to use laminar?
5. solver should be interFoam?
6. some paper and articles about this problem to validate the result like Cd, wave making resistance and some other data.

i'm in force, please help me as soon as you can my friends.
thanks for your attentions and sorry for my bad English.
amin66 is offline   Reply With Quote

Old   June 9, 2012, 07:26
Exclamation
  #2
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
is there any body here that worked on this case before my friends?
amin66 is offline   Reply With Quote

Old   June 13, 2012, 07:41
Default
  #3
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
friends please help me
amin66 is offline   Reply With Quote

Old   June 13, 2012, 08:45
Default
  #4
Senior Member
 
Nima Sam
Join Date: Sep 2009
Location: Tehran, Iran
Posts: 1,123
Blog Entries: 1
Rep Power: 14
nimasam is on a distinguished road
Send a message via Yahoo to nimasam
your question is vague, however let me give you some estimation, it may be incorrect
1) i think the domain atleast should be 2 or 3 times of sphere radius in each direction
2) How is your flow? do you have inlet, outlet? or the sphere is in quiescent liquid (it dpeneds on your simulation)

3,4) i suggest you to find papers in this field, then you will find which turbulence model you should use or when it is turbulence!

5) yes, interFoam is a good choice, it has a color function VOF

6) we are not going to research instead of you friend
amin66 likes this.
nimasam is offline   Reply With Quote

Old   June 14, 2012, 08:45
Default
  #5
Senior Member
 
Albrecht vBoetticher
Join Date: Aug 2010
Location: ZŘrich, Swizerland
Posts: 177
Rep Power: 6
vonboett is on a distinguished road
Hi Amin,

interFoam is a good choice, I'd confirm. One advice: take good care of the turbulence model, if you want to avoid a lot of discussions and not being a turbulence expert, include as much physics to that as possible. My suggestion is using LES, because then you account for the influence of the sphere geometry on the turbulence

(Wendling I.: Dynamische Large-Eddy Simulationen turbulenter Str÷mungen in komplexen Geometrien" PhD Tech University Darmstadt 2007 and Ferziger J. H. "Direct and Large Eddy Simulations of Turbulence" in Numerical Methods in Fluid Mechanics Bd 16)

but check that most parts of the grid should be of hexaedral cells for good accuracy. Use LES together with the Dynamic Mixed Subgrid Scale Model (DMM) for example as developed by the LTT Rostock. You need the DMM model to account for the influence of the free surface on the turbulence, where the so called backscatter-effect plays a key role

(Salvetti et al. "Large-eddy simulation of free-surface decaying turbulence with dynamic subgrid-scale models" In: Phys. Fluids 9(8) 1997)

Look for the LTT Rostoch OpenFOAM extensions, together with their simple grid filter that performs the clipping of negative turbulence viscosities based on Taylor series approximations.

(Kornev et al. "A simple clipping procedure for the dynamic mixed model based on Taylor series approximation" In: Communications in Numerical Methods in Engineering 22 2006)

This setup will make a good shift from laminar to transient to full turbulence and it will take care of your geometry and surface, otherwise you will have to explain very well why your turbulence setup (RANS etc.) fits to your case.

If you use an inlet and you don't use a predefined velocity profile but feed in the fluid as a block with same velocity over height, give the inlet some area without wall friction, otherwise you conflict with typical boundary conditions like noSlip (in the U file) at the slope, followed by some area with wall friction so that the turbulent velocity profile can develop before hitting the sphere.

And another thing: If you have an outlet, use zeroGradient as the boundary condition here in your p_rgh file, if you use fixed value 0 as sometimes recommended your fluid gets reflected at the outlet, funnily only if the outlet is situated in the positive coordinate system quadrant. No explanations for this behavior so far but good to know.
nimasam and amin66 like this.
vonboett is offline   Reply With Quote

Old   June 14, 2012, 11:32
Default
  #6
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
thanks Dear nimasam
i using a cubic domain with inlet outlet and side walls
i searched alot but couldn't find any paper that says in free surface problem around a sphere, which reynolds number is critical number. so i asked question 4
thank you again for your reply and help
amin66 is offline   Reply With Quote

Old   June 14, 2012, 11:37
Default
  #7
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
Thanks Dear vonboett
i will read articles that you mentioned and do your advised and reply the results. thanks again for your help
amin66 is offline   Reply With Quote

Old   June 23, 2012, 12:07
Default
  #8
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
Friends. i need an article that present the value of drag or Cd for different value of submergence depth(cylinder or sphere) and reynolds number.
this cylinder or sphere moving the free surface.

please help if you know or have these articles.
thanks
amin66 is offline   Reply With Quote

Old   July 25, 2012, 13:50
Default
  #9
Senior Member
 
adambarfi's Avatar
 
Mostafa Mahmoudi
Join Date: Jan 2012
Posts: 314
Rep Power: 6
adambarfi is on a distinguished road
Send a message via Yahoo to adambarfi Send a message via Skype™ to adambarfi
you can refer to the White Fluids Mechanics. in this notebook you will find your answers.
I think it was chapter 07: flow past immersed bodies.
adambarfi is offline   Reply With Quote

Old   July 28, 2012, 15:54
Default
  #10
Member
 
Amin
Join Date: Mar 2012
Posts: 60
Rep Power: 5
amin66 is on a distinguished road
Hi Mostafa

I read it before but i couldn't see any thing.
amin66 is offline   Reply With Quote

Old   July 29, 2012, 02:10
Default
  #11
Senior Member
 
adambarfi's Avatar
 
Mostafa Mahmoudi
Join Date: Jan 2012
Posts: 314
Rep Power: 6
adambarfi is on a distinguished road
Send a message via Yahoo to adambarfi Send a message via Skype™ to adambarfi
Quote:
Originally Posted by amin66 View Post
Friends. i need an article that present the value of drag or Cd for different value of submergence depth(cylinder or sphere) and reynolds number.
this cylinder or sphere moving the free surface.

please help if you know or have these articles.
thanks
hi Amin,

the Reynolds number: http://adsabs.harvard.edu/abs/1955JPSJ...10..694K
the Drag Coefficient: http://www.grc.nasa.gov/WWW/k-12/airplane/shaped.html
adambarfi is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
help: wave making resistance on submerged sphere amin66 FLUENT 1 June 13, 2012 07:37
wave making resistance leviathan CFX 12 March 27, 2012 12:39
DecomposePar links against liblamso0 with OpenMPI jens_klostermann OpenFOAM Bugs 11 June 28, 2007 17:51
Ship Wave Making Resistance Yasser CFX 7 April 24, 2006 14:56
meshing F1 front wing Steve FLUENT 0 April 17, 2003 12:37


All times are GMT -4. The time now is 10:34.