- **OpenFOAM**
(*http://www.cfd-online.com/Forums/openfoam/*)

- - **Some questions about the functions ddtPhiCorr(rUA, U, phi) and adjustPhi(phi, U, p)**
(*http://www.cfd-online.com/Forums/openfoam/115157-some-questions-about-functions-ddtphicorr-rua-u-phi-adjustphi-phi-u-p.html*)

Some questions about the functions ddtPhiCorr(rUA, U, phi) and adjustPhi(phi, U, p)Dear all,
I am reading the icoFoam codes, where I find two functions ddtPhiCorr(rUA, U, phi) and adjustPhi(phi, U, p): volScalarField rUA = 1.0/UEqn.A(); U = rUA*UEqn.H(); phi = (fvc::interpolate(U) & mesh.Sf()) + fvc::ddtPhiCorr(rUA, U, phi); adjustPhi(phi, U, p); Could you tell me why the two functions are used here? And where could I find the explanation of these two functions in official documentation? Thank you very much! lwhy |

I'm afraid there aren't any official documents regrading this topic, but you can refer to the source code.
1) adjustPhi(phi, U, p) - source: https://github.com/OpenFOAM/OpenFOAM...hi/adjustPhi.C
- This function is to adjust the flux phi to obey continuity(total flux into the domain equals total flux out from the domain).
This is achieved in the following way:
Total flux = massIn - fixedMassOut - massCorr * adjustableMassOut where- massCorr = (massIn - fixedMassOut)/adjustableMassOut
- massIn: Total flux into the domain
- fixedMassOut: Total flux out from the domain through the boundaries on which the velocity is prescribed
- adjustableMassOut: Total flux from the domain through the boundaries on which the velocity is NOT fixed
We can make the total flux equal 0 by adjusting the adjustableMassOut by multiplying it by massCorr.
2)ddtPhiCorr(rUA, U, phi) You might want to read the following thread http://www.cfd-online.com/Forums/ope...rua-u-phi.htmlHope this helps, Fumiya |

Quote:
Why is adjustPhi taken away in, e.g. compressibleInterFoam? Shouldn't the flux still be adjusted to satisfy continuity at the boundary? Best regards, Lesie |

adjustPhi is taken away from compressible solvers because you are no longer solving Poisson equation for getting the pressure. look at post #4 in http://www.cfd-online.com/Forums/ope...adjustphi.html
so there are no singularities to be dealt with. for example lets look at pEqn in laminarSMOKE : fvScalarMatrix pEqn ( fvm::ddt(psi, p) + fvc::div(phi) - fvm::laplacian(rho*rUA, p) ); |

All times are GMT -4. The time now is 01:19. |