[mayank.dce2k7]

Hi Foamers,

I recently switched from OF-2.1.1 to OF-2.2.1. I installed swak4Foam it compiled fine which was checked by re-running ./Allwmake command which returned the list of libraries. Now I ran a simple steady state simulation using swak Data entry and encountered errors which were not there in OF-2.1.1.

Below is 0/U file: where I implemented swakDataEntry.

/*--------------------------------*- C++ -*----------------------------------*\
| =========                 |                                                 |
| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
|  \\    /   O peration     | Version:  2.1.1                                 |
|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
|    \\/     M anipulation  |                                                 |
\*---------------------------------------------------------------------------*/
FoamFile
{
    version     2.0;
    format      ascii;
    class       volVectorField;
    object      U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //



dimensions      [0 1 -1 0 0 0 0];

internalField  uniform (0 0 0);

boundaryField
{
    INLET
    {

       type            groovyBC;
       variables "r2=(pow(pos().x,2)+pow(pos().y,2));R2=sum(area())/pi;para=-((R2-r2)/R2)*normal();";
       valueExpression "2*0.0852*para"; //where 0.351 is the average velocity
       value        uniform (0 0 0);      
     
    }

    PART_1
    {
        type            fixedValue;
        value           uniform (0 0 0);
    }

    OUTLET1
    {

        type            flowRateInletVelocity;
        volumetricFlowRateExpression "0";
        volumetricFlowRate swak { 
            variables "phi1{INLET}=-0.502*sum(area())*0.0852;"; 
            expression "phi1"; // volume flow going out of domain from outlet 1 which 0.52 times that at inlet
            valueType patch;
            patchName OUTLET1;};

     value           uniform ( 0 0 0 );
    }

    OUTLET2
    {

       type            zeroGradient;
        
    }


}

Error message:

Create mesh for time = 0

Reading field p

Reading field U



--> FOAM FATAL IO ERROR:
keyword independentVariableName is undefined in dictionary ""

file: from line 47 to line 50.

From function dictionary::lookupEntry(const word&, bool, bool) const
in file db/dictionary/dictionary.C at line 402.

FOAM exiting

[gschaider]

Originally Posted by mayank.dce2k7

Hi Foamers,

I recently switched from OF-2.1.1 to OF-2.2.1. I installed swak4Foam it compiled fine which was checked by re-running ./Allwmake command which returned the list of libraries. Now I ran a simple steady state simulation using swak Data entry and encountered errors which were not there in OF-2.1.1.

Below is 0/U file: where I implemented swakDataEntry.

/*--------------------------------*- C++ -*----------------------------------*\
| =========                 |                                                 |
| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
|  \\    /   O peration     | Version:  2.1.1                                 |
|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
|    \\/     M anipulation  |                                                 |
\*---------------------------------------------------------------------------*/
FoamFile
{
    version     2.0;
    format      ascii;
    class       volVectorField;
    object      U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //



dimensions      [0 1 -1 0 0 0 0];

internalField  uniform (0 0 0);

boundaryField
{
    INLET
    {

       type            groovyBC;
       variables "r2=(pow(pos().x,2)+pow(pos().y,2));R2=sum(area())/pi;para=-((R2-r2)/R2)*normal();";
       valueExpression "2*0.0852*para"; //where 0.351 is the average velocity
       value        uniform (0 0 0);      
     
    }

    PART_1
    {
        type            fixedValue;
        value           uniform (0 0 0);
    }

    OUTLET1
    {

        type            flowRateInletVelocity;
        volumetricFlowRateExpression "0";
        volumetricFlowRate swak { 
            variables "phi1{INLET}=-0.502*sum(area())*0.0852;"; 
            expression "phi1"; // volume flow going out of domain from outlet 1 which 0.52 times that at inlet
            valueType patch;
            patchName OUTLET1;};

     value           uniform ( 0 0 0 );
    }

    OUTLET2
    {

       type            zeroGradient;
        
    }


}

Error message:

Create mesh for time = 0

Reading field p

Reading field U



--> FOAM FATAL IO ERROR:
keyword independentVariableName is undefined in dictionary ""

file: from line 47 to line 50.

From function dictionary::lookupEntry(const word&, bool, bool) const
in file db/dictionary/dictionary.C at line 402.

FOAM exiting

You probably also upgraded from an old swak to 0.2.4. To quote from the README there

**** =swakDataEntry= improved
     Two enhancements
     - the name of the independent variable  no can be
       specified. This variable holds the value that is passed to the
       data entry as a uniform value
     - data entry can now be integrated. This allows using it for
       instance for the injection rate in lagrangian models

the reference guide in the Documentation folder explains it

** Data entry
   The main library introduces a subtype of =DataEntry= that is
   selected under the name =swak= wherever data entries lie
   =constant=, =polynomial= etc are used. After that a dictionary with
   additional parameters is required. An example entry would look
   like this:
: flowRateProfile swak {
:     expression "exp(-t)";
:     independentVariableName t;
:     valueType patch;
:     patchName top;
:     integrationIntervalls 100;
: };
   Required entries in the dictionary are
   - expression :: the expression to be evaluated
   - independentVariableName :: the name of the independent variable
        that was passed during evaluation (usually this is the time)
   - valueType :: this determines the type of parser that is
                  used. Additional parameters for the initialization
                  may be needed and the usual entries like
                  =variables= are of course possible
   Only for integrations an additional parameter is needed
   - integrationIntervalls :: number of intervals the integration
        range is divided into.

The day when people start reading these file ...