
[Sponsors] 
January 15, 2010, 04:59 
Aeroacoustics with coodles

#1 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Dear All,
I would like to open a thread dedicated for aeroacoustics, since such kind of problems is a bit different from general cfd. I saw some threads about it, but all were rather old ones, I hope still someone working on this direction. Yesterday I already posted this, but I think on a wrong thread (it was about preprocessing as I later realized, sorry posting it twice, but I would like to bring my problem front of the right community). So, I tried to simulate an acoustic pulse placed in the middle of a rectangular domain. The pulse should spread with the speed of sound unidirectionally. This happens well, BUT, in the density field there remains a smaller pulse constantly. This I do not understand, it seams that there and entropy pulse created, due to I do not know what. My initial problem: velocity is zero everywhere gaussian pulse of pressure at the center of the domain (set by funkySet Field) Op. 1: constant temperature, hoping that the "thermo" package will set the density well Op. 2: set the density too as a gauss pressure rho = 1/(c*c)*p Both initializations give back exactly the same results. I normalized the pressure by pNorm = p/(c*c) +0.327 where the correction is exactly the same as the amplitude of the remaining pulse. In this case the density and normP plots are the same (except that in the density there is the extra bump ) have you any idea where I introduce this additional pulse? Thanks, Lilla 

January 15, 2010, 06:35 

#2 
Senior Member

Hi Lilla,
post some pictures of your calculations, it could be easier to help you with them. Moreover, put attention in normalizing variables in OF, as the solvers work with dimensional variables! 

January 15, 2010, 10:05 

#3 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Dear Ivan,
I used dimensional values. p_0 = 10000Pa U_0 = (0 0 0)  no background flow T_0= 300K and superimposed to them the pulse (maximum amplitude of 1 kg/m^3, ok this could be a bit high...), namely the pressure or the pressure and density. Well, I would upload image, but when I click to the icon it is asking an url address and from there I'm lost. So I created an album, it is in well, here, if I write it: http://www.cfdonline.com/Forums/mem...++coodles.html Lilla 

January 18, 2010, 01:07 

#4 
Senior Member
Fabian Braennstroem
Join Date: Mar 2009
Posts: 407
Rep Power: 10 
Hi Lilla,
I wonder, how you set the gaussian pulse with funkySetFields... do you have a hint!? Fabian 

January 18, 2010, 05:57 
gaussian pulse

#5 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Like that:
expressions ( benchP { field p; expression "100000+0.1*340*340*exp(log(2.)/9.*(pos().x*pos().x+pos().y*pos().y))"; } /* benchR { field rho; expression "1.163+exp(log(2.)/9.*(pos().x*pos().x+pos().y*pos().y))"; //+0.1*exp(log(2.)/25.*((pos().x67.)*(pos().x67.)+(pos().y67.)*(pos().y67.)))"; } benchU { field U; expression "U+vector(0.04*(pos().y67.)*exp(log(2.)/25.*((pos().x67.)*(pos().x67.)+(pos().y67.)*(pos().y67))),0.04*(pos().x67.)*exp(log(2.)/25.*((pos().x67.)*(pos().x67.)+(pos().y67.)*(pos().y67.))), 0.0)"; } */ ); This is a benchmark problem from the ICASE/LaRC Workshop... from NASA (NASA CP3300). Here an acoustic and a entropy/shear pulse are defined. I deleted the later one, so just the acoustic pulse remained. The adventage of the testcase, that it has analytical solution. Lilla Lilla 

January 20, 2010, 06:44 
localising the problem

#6 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
I found out where the simulation is going wrong, now I just do not know exactly why.
In the initialization we have due to the perfect gas law: rhomax=pmax/(R*T)=1.2933, which should be equal in isentropic flow rho=c^2*p as c=sqrt(gamma/(R*T))=const as T =const., however in this way with gamma = 1.4 rhomax = 1.2586. So seems gamma do not fit. The difference between the two remains in the computational domain as an entropy wave. Unfortunatelly here a 3% of error is introduced which is not that much, I know, but in the present case more than annoying. I do not know how to overcome this problem. Any suggestion is very wllcomed! Lilla 

January 20, 2010, 07:55 
correction

#7 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Sorry, I was a bit too fast:
p=rho0+c^2*(rhorho0) But the numbers are ok. 

February 5, 2010, 04:26 

#8 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Dear,
I realised my mistake, so to complete this tread: The perturbations do not satisfy by themselves the perfect gas law, the instantaneous quantities do (like p=p0+p', etc.). So where I computed T'=m/R*p'/rho'=const. is not valid. Instead T=m/R*(p0+p')/(rho0+rho'). This is the closure of the initial value problem of an acoustic pulse. Best regards, Lilla 

April 29, 2014, 08:49 

#9 
New Member
J.S.
Join Date: Jul 2012
Location: Germany
Posts: 4
Rep Power: 5 
Dear Lilla,
I know this is a quit old thread, but nevertheless thanks for opening it. I had implemented acoustic analogies in Openfoam and I wanted to verify my results by running the NASA Benchmark Test case. I have been successful in running my OFcase but now I stuck in generating/plotting the analytical solution to compare my numerical results with the exact one. Do you (or anybody else) have any helping hint? Do I have to solve the Integral of the analytical solution manually to get values along the xaxis for a specific timestep? Thanks a lot in advance? JS 

April 29, 2014, 10:59 

#10 
Member
Kapa Lilla
Join Date: Mar 2009
Location: Bruxelles, Belgium
Posts: 45
Rep Power: 8 
Hi,
yes, you need to integrate numerically (I've used matlab fort he pulse) to get the solution. There is not closed solution for such problems. Best, Lilla 

April 29, 2014, 13:06 

#11 
New Member
J.S.
Join Date: Jul 2012
Location: Germany
Posts: 4
Rep Power: 5 
Hi Lilla,
thank you very much for your quick reply. And as I understand correctly, I was on the right path ;). Hope the matlabcoding is not that much work... is the there a kind of usefull "hidden" function in Matlab/Octave for it? Best regards, Jan 

Tags 
acoustic, coodles 
Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Nonphysical flow field while using coodles solver  ankgupta8um  OpenFOAM Running, Solving & CFD  5  January 26, 2008 17:54 
Startingsetting coodles on an academic case  melanie  OpenFOAM Running, Solving & CFD  5  March 30, 2006 04:00 
aeroacoustics  Constantinos  Main CFD Forum  1  March 22, 2004 14:32 
Aeroacoustics  Flow over Cylinder  Axel Rohde  Main CFD Forum  2  August 17, 2002 12:18 
aeroacoustics  jonathan  Main CFD Forum  2  February 4, 2002 09:14 