CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > OpenFOAM

low Reynolds Model for pipe flow

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   July 1, 2011, 04:57
Default low Reynolds Model for pipe flow
  #1
Member
 
Martin
Join Date: Aug 2010
Location: Germany
Posts: 55
Rep Power: 6
RugbyGandalf is on a distinguished road
Dear Community,

i would like to simulate a pipe flow with has a low Reynolds - Number.

Does someone know, what low-Re-turbulence-model is best for?
I already tried using LaunderSharma KE - it works with only 2% difference from u_max in comparison with Hagen-Poiseuille - but i do not know, if LaunderSharmaKE was developed for such applications.

So does someone know about this?
I am using the simpleFoam solver!

Greetings

Martin

Last edited by RugbyGandalf; July 1, 2011 at 04:58. Reason: solver added
RugbyGandalf is offline   Reply With Quote

Old   July 1, 2011, 06:40
Default
  #2
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Quote:
Originally Posted by RugbyGandalf View Post
Dear Community,

i would like to simulate a pipe flow with has a low Reynolds - Number.

Does someone know, what low-Re-turbulence-model is best for?

Martin,

it is a pitfall: A Low-Reynolds turbulence model is NOT designed for low reynolds numbers. It is designed for resolving the near wall layer without wall functions. Therefore, you need to create your mesh different if you use a low-Re model compared to a Hi-Re model. I suspect for a pipe flow with modest separations a Hi-Re model should be sufficient. However, you have to make sure your mesh fits for a Hi-Re model.

Regards Bastian
bastil is offline   Reply With Quote

Old   July 1, 2011, 08:51
Default
  #3
Member
 
The True
Join Date: Dec 2010
Posts: 80
Rep Power: 6
Eren10 is on a distinguished road
Is there a tutorial of LaunderSharma, I want to copy their files, however, the files of LaunderSharma should be almost the same as the k epsilon.
Eren10 is offline   Reply With Quote

Old   July 1, 2011, 08:54
Default
  #4
Member
 
Martin
Join Date: Aug 2010
Location: Germany
Posts: 55
Rep Power: 6
RugbyGandalf is on a distinguished road
I need to resolve the near wall layers without wallfunctions!
The Reynolds-Numbers vary between 150 up to 320...

I do not think, that a high Re - Model is able to solve the flow right!
My pipe has a diameter of 0.004 m - in fact it consists only of near wall layers

i also added a picture showing my grid and one which shows the velocity field, that kOmegaSST Model offers in comparison to Hagen-Poiseuille-profile!

Martin
Attached Images
File Type: png OGRID.png (32.6 KB, 64 views)
File Type: png ValidierungSST.png (18.4 KB, 59 views)
RugbyGandalf is offline   Reply With Quote

Old   July 1, 2011, 10:20
Default
  #5
Senior Member
 
BastiL
Join Date: Mar 2009
Posts: 471
Rep Power: 11
bastil is on a distinguished road
Quote:
Originally Posted by RugbyGandalf View Post
I need to resolve the near wall layers without wallfunctions!
Why?


Quote:
Originally Posted by RugbyGandalf View Post
The Reynolds-Numbers vary between 150 up to 320...
Well in that case I think your case is laminar and you need to run it laminar, e.g. without turbulence models... Otherwise you imprint turbulence where none exists.

If you still want to run a low Reynolds model (even though it is not necessary) you need to have a much lower thickness of the first cell next to the wall. The appropriate value of this can be estimated with the y+ value.

Regards Bastian.
bastil is offline   Reply With Quote

Old   July 1, 2011, 10:32
Default
  #6
Member
 
Guifan Li
Join Date: Apr 2011
Location: New York City, U.S.
Posts: 96
Rep Power: 6
liguifan is on a distinguished road
Hi Martin,

You mesh look quite nice.

Just want to ask that did you use transfinite progression stuff to make the layers at boundary more denser than those away from boundary?

Thanks a lot.
liguifan is offline   Reply With Quote

Old   July 2, 2011, 05:24
Default
  #7
Member
 
Robert Ong
Join Date: Aug 2010
Posts: 45
Rep Power: 6
rob3rt 0ng is on a distinguished road
Hi Eren,

You can lookup nacaAirFoil tutorial but it's for compressible case though. Otherwise, you always can look for launderSharma codes from Doxygen.

Regards,
Robert
rob3rt 0ng is offline   Reply With Quote

Old   July 2, 2011, 11:35
Default
  #8
Senior Member
 
Martin Hegedus
Join Date: Feb 2011
Posts: 497
Rep Power: 9
Martin Hegedus is on a distinguished road
Quote:
Originally Posted by RugbyGandalf View Post
Dear Community,

i would like to simulate a pipe flow with has a low Reynolds - Number.

Does someone know, what low-Re-turbulence-model is best for?
I already tried using LaunderSharma KE - it works with only 2% difference from u_max in comparison with Hagen-Poiseuille - but i do not know, if LaunderSharmaKE was developed for such applications.

So does someone know about this?
I am using the simpleFoam solver!

Greetings

Martin
Interesting, I never gave much thought to a turbulence model in a pipe before, until now. I'm just hypothesizing, but I assume the eddy viscosity might keep building inside the pipe. Of course close to the walls the eddy viscosity is forced to go to zero. A low turbulence model might just delay the build-up. Eventually an equilibrium will be reached between the construction and destruction terms. Because of the eddy viscosity distribution, your velocity will be flatish on top (i.e. the high eddy viscosity in the middle makes the center flow rigid) and steep on the side (since eddy viscosity goes to zero at side).

Laminar is probably the way to go.

Just my thoughts, and if anyone disagrees with my conjecture, please include your thoughts.
Martin Hegedus is offline   Reply With Quote

Old   July 4, 2011, 11:19
Default
  #9
Member
 
Martin
Join Date: Aug 2010
Location: Germany
Posts: 55
Rep Power: 6
RugbyGandalf is on a distinguished road
Dear Bastian,

what y+ value do i need? My calculations actually run with y+ avg of 0.8...
is this to high?

@ Martin:
maybe laminar seems to be the best way... it was a test with low-Re... In fact, LaunderSharmaKE gives out great results. I will also calculate all my cases with laminar flow and compare them with LaunderSharmaKE.

For information: LaunderSharmaKE was originally designed to solve the flow and heat / mass transfer near a rotating disk.

@ liguifan: i used meshGrading with blockMesh to make the cells finer at the wall.
RugbyGandalf is offline   Reply With Quote

Old   July 4, 2011, 11:28
Default
  #10
Member
 
Martin
Join Date: Aug 2010
Location: Germany
Posts: 55
Rep Power: 6
RugbyGandalf is on a distinguished road
I also have another question:

i am calculating the flow through bend pipes, to get to know about the wall shear stress:

Does someone have an idea, how i could get wall shear stress in cylinder coordinates from a result, that gives out Cartesian ones?
The aim is, to get a chart, which shows the wall stress in dependence from pipe-lenght...

maybe the pictures will make it clearer! The chart is only an example!

Thank you very much for your answers!

Martin
Attached Images
File Type: jpg stenosis50.jpg (40.4 KB, 32 views)
File Type: png wall shear stress over lenght.png (43.2 KB, 27 views)
RugbyGandalf is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Low Reynolds number k-E Turbulent Model Sohail FLUENT 13 December 3, 2013 12:59
SOS Low Reynolds model or Realizable k ε model? panos_metal FLUENT 0 January 18, 2011 15:05
Low Reynolds K-Epsilon model Implementation in Fortran 90 Federico Main CFD Forum 0 December 16, 2010 12:23
Flow over sphere low reynolds number kadirggg Main CFD Forum 2 November 2, 2010 15:06
Low reynolds model for non newtonian fluids Kimo FLUENT 0 July 22, 2007 11:36


All times are GMT -4. The time now is 03:33.