Creating a symmTensorField from a scalarField

maninthemail · September 29, 2011, 11:51

Greetings,

I'm implementing a boundary condition for a symmTensor variable. I calculate a scalarField, and then want to apply it to the diagonal components of the symmTensorField. The fields are turbulent intensity and reynolds stress, though that really isn't important. The relevant (updateCoeffs) part of the code is as follows...

Code:

if (updated()) return;

// boundary velocity
const fvPatchVectorField& Up = patch().lookupPatchField<volVectorField, vector>(UName_);

// "value" is one third of the turbulent intensity
scalarField value = 0.5*sqr(intensity_)*magSqr(Up);

// "stress" is a symmetric tensor field with diagonal elements equal to "value"
symmTensorField stress;

// I don't know how to set the values in the tensor
/*
 *          / value  0.0   0.0  \
 * stress = |  0.0  value  0.0  |
 *          \  0.0   0.0  value /
 */

operator==(stress);

fixedValueFvPatchSymmTensorField::updateCoeffs();

As you can see, it is transferring the scalarField values to the symmTensorField which I can't work out how to do. There are no existing derived tensor boundary conditions to copy off, so I'm stuck for ideas. If anyone could help, I'd be eternally grateful.

Many thanks, and apologies for reposting this. No-one replied to the last post I made, and I've had some time to re-formulate the question, hopefully a little more clearly.

Bernhard · September 29, 2011, 14:11

Did you already try something like this:

Code:

symmTensorField stress(value,0,0,value,0,value);

I am not sure if it works like this, but otherwise you may want to try:

Code:

symmTensor I(1,0,0,1,0,1);
symmTensorField stress=value*I;

However, for both I am not sure if it works, but it may give you some directions, good luck!

maninthemail · September 30, 2011, 04:13

The second of those works. Thank you very much.

meihua · October 17, 2018, 18:19

Quote:

Originally Posted by maninthemail

Greetings,

I'm implementing a boundary condition for a symmTensor variable. I calculate a scalarField, and then want to apply it to the diagonal components of the symmTensorField. The fields are turbulent intensity and reynolds stress, though that really isn't important. The relevant (updateCoeffs) part of the code is as follows...

Code:

if (updated()) return;

// boundary velocity
const fvPatchVectorField& Up = patch().lookupPatchField<volVectorField, vector>(UName_);

// "value" is one third of the turbulent intensity
scalarField value = 0.5*sqr(intensity_)*magSqr(Up);

// "stress" is a symmetric tensor field with diagonal elements equal to "value"
symmTensorField stress;

// I don't know how to set the values in the tensor
/*
 *          / value  0.0   0.0  \
 * stress = |  0.0  value  0.0  |
 *          \  0.0   0.0  value /
 */

operator==(stress);

fixedValueFvPatchSymmTensorField::updateCoeffs();

As you can see, it is transferring the scalarField values to the symmTensorField which I can't work out how to do. There are no existing derived tensor boundary conditions to copy off, so I'm stuck for ideas. If anyone could help, I'd be eternally grateful.

Many thanks, and apologies for reposting this. No-one replied to the last post I made, and I've had some time to re-formulate the question, hopefully a little more clearly.

Hi Bill,
I'm implementing a boundary condition for a symmTensor variable now, but I do not know how to start. Could you share your solver or case?

Thanks in advance.

Meihua

maninthemail · October 18, 2018, 04:11

This post is 7 years old. I don't have the files any more.

If you want to write a boundary condition for a symmetric tensor, you can run the following to get you started...

Code:

foamNewBC -f -symmTensor myBoundaryCondition

meihua · October 19, 2018, 00:06

Quote:

Originally Posted by maninthemail

This post is 7 years old. I don't have the files any more.

If you want to write a boundary condition for a symmetric tensor, you can run the following to get you started...

Code:

foamNewBC -f -symmTensor myBoundaryCondition

Thank you, Bill.

meihua · October 29, 2018, 23:21

Quote:

Originally Posted by maninthemail

This post is 7 years old. I don't have the files any more.

If you want to write a boundary condition for a symmetric tensor, you can run the following to get you started...

Code:

foamNewBC -f -symmTensor myBoundaryCondition

Hi Bill,

Another question about tensor boundary condition. If I set a tensor on the boundary, how can it exist? I mean it seems that a tensor cannot exist on a surface, but in OpenFoam, the boundaries are surfaces. Maybe my understanding is wrong. Thanks in advance!

maninthemail · November 15, 2018, 03:37

The geometry that the field is associated with does not impose any limit on the data type. The field in question is just a list of symmTensors, one per patch face. How they relate to the patch geometry (face normals, areas, etc...) depends on your implementation.

kindle · November 26, 2018, 15:29

This command seems not to be in OF-2.3.x.

Is it new ?

Quote:

Originally Posted by maninthemail

This post is 7 years old. I don't have the files any more.

If you want to write a boundary condition for a symmetric tensor, you can run the following to get you started...

Code:

foamNewBC -f -symmTensor myBoundaryCondition

meihua · November 26, 2018, 15:32

Quote:

Originally Posted by kindle

This command seems not to be in OF-2.3.x.

Is it new ?

For OF 5.0, it works.

meihua · November 26, 2018, 15:33

Quote:

Originally Posted by kindle

This command seems not to be in OF-2.3.x.

Is it new ?

Are you also developing some symmtensor boundary?

kindle · November 26, 2018, 16:03

Not for now. I'm actually working on simple non-newtonian turbulent mixing.

I was targeting the FENE model where there are symmTensor tau. But I dropped that... Programming in OpenFOAM is not evident. At the time I was interested in creating a moving BC for FENE for specific type "symmTensor".

kindle · November 26, 2018, 16:18

Tensorial BC exists.

Take a look at http://https://github.com/fppimenta/rheoTool/blob/master/of40/tutorials/rheoFoam/Cavity/Oldroyd-BLog/0/tau

Where tau (That I mentioned in previous post) is a symmTensor.

Pavithra · April 22, 2023, 06:43

Hi Everyone,

Is it possible to use codedFixedValue boundary condition to define boundary value of a symmTensor field ?

I am working on rheoTool and I need to set Poiseuille stress profile at the inlet.

Code:

    inlet
    {
	type            codedFixedValue;
	value		uniform (0 0 0 0 0 0);
	
	name 		poisStress;
	
	code
	#{
			const vectorField& Cf = patch().Cf();
			vectorField& field = *this;
			
			const scalar q = 1e-06;
			const scalar h0 = 0.4e-03;
			const scalar l = 0.4e-03;
					
			forAll(Cf, faceI)
			{
				const scalar y = Cf[faceI][1];
				
				field[faceI] = symmTensor((1 + 4.50 * ((l*q*y)/(h0*h0*h0)) * ((l*q*y)/(h0*h0*h0))),(-(3*l*q*y)/(2*h0*h0*h0)),0,1,0,0);
			}
			
	#};       
    }

This is what I have tried and I am geting the following error.

Code:

Using dynamicCode for codedFixedValue poisStress at line 24 in "/home/pavi/OpenFOAM/pavi-9/run/De03/0/tau/boundaryField/inlet"
Creating new library in "dynamicCode/poisStress/platforms/linux64GccDPInt32Opt/lib/libpoisStress_abc86e80ab96b5188231ac88cede6087b6e5bd77.so"
"/opt/openfoam9/etc/codeTemplates/dynamicCode/codedFixedValueFvPatchFieldTemplate.C" "/home/pavi/OpenFOAM/pavi-9/run/De03/dynamicCode/poisStress/codedFixedValueFvPatchFieldTemplate.C"
"/opt/openfoam9/etc/codeTemplates/dynamicCode/codedFixedValueFvPatchFieldTemplate.H" "/home/pavi/OpenFOAM/pavi-9/run/De03/dynamicCode/poisStress/codedFixedValueFvPatchFieldTemplate.H"
Invoking "wmake -s libso /home/pavi/OpenFOAM/pavi-9/run/De03/dynamicCode/poisStress"
wmake libso /home/pavi/OpenFOAM/pavi-9/run/De03/dynamicCode/poisStress
    ln: ./lnInclude
    wmkdep: codedFixedValueFvPatchFieldTemplate.C
    Ctoo: codedFixedValueFvPatchFieldTemplate.C
/home/pavi/OpenFOAM/pavi-9/run/De03/0/tau/boundaryField/inlet: In member function ‘virtual void Foam::poisStressFixedValueFvPatchSymmTensorField::updateCoeffs()’:
/home/pavi/OpenFOAM/pavi-9/run/De03/0/tau/boundaryField/inlet:32:25: error: invalid initialization of reference of type ‘Foam::vectorField&’ {aka ‘Foam::Field<Foam::Vector<double> >&’} from expression of type ‘Foam::poisStressFixedValueFvPatchSymmTensorField’
/home/pavi/OpenFOAM/pavi-9/run/De03/0/tau/boundaryField/inlet:42:42: error: no match for ‘operator=’ (operand types are ‘Foam::Vector<double>’ and ‘Foam::symmTensor’ {aka ‘Foam::SymmTensor<double>’})

I understand that the error message states that I am initializing a vector field as a tensor field. Someone please help me with the right syntax.

Thank You.

September 29, 2011, 11:51	Creating a symmTensorField from a scalarField	#1
maninthemail New Member Bill Join Date: Jun 2011 Location: UK Posts: 16 Rep Power: 14	Greetings, I'm implementing a boundary condition for a symmTensor variable. I calculate a scalarField, and then want to apply it to the diagonal components of the symmTensorField. The fields are turbulent intensity and reynolds stress, though that really isn't important. The relevant (updateCoeffs) part of the code is as follows... Code: if (updated()) return; // boundary velocity const fvPatchVectorField& Up = patch().lookupPatchField<volVectorField, vector>(UName_); // "value" is one third of the turbulent intensity scalarField value = 0.5sqr(intensity_)magSqr(Up); // "stress" is a symmetric tensor field with diagonal elements equal to "value" symmTensorField stress; // I don't know how to set the values in the tensor /* * / value 0.0 0.0 \ * stress = \| 0.0 value 0.0 \| * \ 0.0 0.0 value / */ operator==(stress); fixedValueFvPatchSymmTensorField::updateCoeffs(); As you can see, it is transferring the scalarField values to the symmTensorField which I can't work out how to do. There are no existing derived tensor boundary conditions to copy off, so I'm stuck for ideas. If anyone could help, I'd be eternally grateful. Many thanks, and apologies for reposting this. No-one replied to the last post I made, and I've had some time to re-formulate the question, hopefully a little more clearly.

September 29, 2011, 14:11		#2
Bernhard Senior Member Bernhard Join Date: Sep 2009 Location: Delft Posts: 790 Rep Power: 21	Did you already try something like this: Code: symmTensorField stress(value,0,0,value,0,value); I am not sure if it works like this, but otherwise you may want to try: Code: symmTensor I(1,0,0,1,0,1); symmTensorField stress=value*I; However, for both I am not sure if it works, but it may give you some directions, good luck! Tushar@cfd and ashvinc9 like this.

October 18, 2018, 04:11		#5
maninthemail New Member Bill Join Date: Jun 2011 Location: UK Posts: 16 Rep Power: 14	This post is 7 years old. I don't have the files any more. If you want to write a boundary condition for a symmetric tensor, you can run the following to get you started... Code: foamNewBC -f -symmTensor myBoundaryCondition meihua likes this.

November 26, 2018, 16:18	Tensorial BC	#13
kindle New Member Join Date: Aug 2016 Posts: 16 Blog Entries: 68 Rep Power: 9	Tensorial BC exists. Take a look at http://https://github.com/fppimenta/rheoTool/blob/master/of40/tutorials/rheoFoam/Cavity/Oldroyd-BLog/0/tau Where tau (That I mentioned in previous post) is a symmTensor.

Similar Threads
Thread	Thread Starter	Forum	Replies	Last Post
[Commercial meshers] Fluent3DMeshToFoam	simvun	OpenFOAM Meshing & Mesh Conversion	50	January 19, 2020 15:33
[blockMesh] Problems in creating a wedge type mesh	Joscha	OpenFOAM Meshing & Mesh Conversion	28	August 3, 2019 07:59
Problem in running ICEM grid in Openfoam	Tarak	OpenFOAM	6	September 9, 2011 17:51
Problems with Meshing: Collapsed Cells	Emmanuel Resch	Siemens	1	July 30, 2007 03:02
Gerris software installation	mer	Main CFD Forum	2	November 12, 2005 08:50

September 30, 2011, 04:13		#3
maninthemail New Member Bill Join Date: Jun 2011 Location: UK Posts: 16 Rep Power: 14	The second of those works. Thank you very much.

November 15, 2018, 03:37		#8
maninthemail New Member Bill Join Date: Jun 2011 Location: UK Posts: 16 Rep Power: 14	The geometry that the field is associated with does not impose any limit on the data type. The field in question is just a list of symmTensors, one per patch face. How they relate to the patch geometry (face normals, areas, etc...) depends on your implementation.

November 26, 2018, 16:03		#12
kindle New Member Join Date: Aug 2016 Posts: 16 Blog Entries: 68 Rep Power: 9	Not for now. I'm actually working on simple non-newtonian turbulent mixing. I was targeting the FENE model where there are symmTensor tau. But I dropped that... Programming in OpenFOAM is not evident. At the time I was interested in creating a moving BC for FENE for specific type "symmTensor".