CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Pointwise & Gridgen

Pointwise Mesh to Fluent Multiblock Issue

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   January 26, 2016, 10:39
Default Pointwise Mesh to Fluent Multiblock Issue
  #1
New Member
 
Join Date: Jun 2014
Posts: 6
Rep Power: 3
NeroBlade is on a distinguished road
Hey folks,

I've stumbled upon an issue that I've been experiencing lately when I've started using the Pointwise meshing software and exporting the mesh onto Fluent.

I setup the structured meshing parameters for each edge to suit my needs for a simple cube case and then I select all the blocks generated and export a new case file. The cube and floor is wall, sides and top are symmetric and an inlet and outlet is included.

Everything seems fine until I run the simulation with the same physics as before but the converged result seems to have some interface problems between each block as shown on the below image.

The exported mesh contains two interior blocks one being the blocks themselves and the second being the interface in between.

Any suggestions of idea why does this occur and would anyone know how to resolve this?

Cheers,
Lee
Attached Images
File Type: png tp_multi_PW.png (81.4 KB, 8 views)
NeroBlade is offline   Reply With Quote

Old   January 28, 2016, 23:33
Default
  #2
Senior Member
 
Chris Sideroff
Join Date: Mar 2009
Location: Ottawa, ON, CAN
Posts: 381
Rep Power: 12
cnsidero is on a distinguished road
In Pointwise create a Volume Condition, assign both blocks to it and change the type to Fluid. Then when you export the mesh to Fluent there will be one zone and the interior interface between them will disappear.
cnsidero is offline   Reply With Quote

Old   January 29, 2016, 08:01
Default
  #3
New Member
 
Join Date: Jun 2014
Posts: 6
Rep Power: 3
NeroBlade is on a distinguished road
Thank you cnsidero, I gave that a shot and exported it but I still have the two interior zones.

I selected all the outer blocks around the cube and assigned the volume condition as fluid and the cube itself I assigned it as solid and exported.

Below is the screenshot of the issue.
Attached Images
File Type: png two_interiors.png (63.5 KB, 7 views)
NeroBlade is offline   Reply With Quote

Old   January 29, 2016, 09:34
Default
  #4
Senior Member
 
Chris Sideroff
Join Date: Mar 2009
Location: Ottawa, ON, CAN
Posts: 381
Rep Power: 12
cnsidero is on a distinguished road
This likely means some blocks are not point matched. Go to Set CAE Boundary Conditions. If any internal domains are selectable then your blocks are not point matched (e.g. mismatching connectors).
cnsidero is offline   Reply With Quote

Old   January 29, 2016, 10:08
Default
  #5
New Member
 
Join Date: Jun 2014
Posts: 6
Rep Power: 3
NeroBlade is on a distinguished road
Okay, because what I've done was I've created the connectors for one side and then copied the connectors and pasted them in a translated position via z axis. Then afterwards used connectors to connect the two sets of connectors together. Is this the correct procedure?

I checked via boundary conditions and no internal domains are selectable, which is a good sign.
NeroBlade is offline   Reply With Quote

Old   January 29, 2016, 10:19
Default
  #6
Senior Member
 
Chris Sideroff
Join Date: Mar 2009
Location: Ottawa, ON, CAN
Posts: 381
Rep Power: 12
cnsidero is on a distinguished road
It's tough for me to tell what the issue is. Are you able to attach the .pw file (or provide it some other means)?
cnsidero is offline   Reply With Quote

Old   January 29, 2016, 16:19
Default
  #7
New Member
 
Join Date: Jun 2014
Posts: 6
Rep Power: 3
NeroBlade is on a distinguished road
Sure okay, here's the .pw file.

https://www.dropbox.com/s/8qvm442l2y...ube_0h.pw?dl=0
NeroBlade is offline   Reply With Quote

Old   February 1, 2016, 12:07
Default
  #8
Member
 
Zach Davis
Join Date: Jan 2010
Location: Fort Worth, TX
Posts: 30
Rep Power: 8
RcktMan77 is on a distinguished road
I believe the interior boundary condition within FLUENT is just its way of identifying the interior faces between blocks. It uses this interior boundary condition to interpolate solution information at these faces.

After looking at the initial picture of your solution that you posted and then your mesh, I think the issue you're having is more due to the large jumps in spacing the you have. For example there's a 40x jump between the mesh spacing on the face of your block and the initial spacing used to resolve the viscous region surrounding the cube. A similar jump exists between the blocks aligned in the same y-plane as your cube and the farfield mesh adjacent to it. You want to avoid jumps like this and have a smooth transition between cells where the growth rate between cells is no larger than 1.2.

As information is interpolated along these interior faces, you don't want to have large jumps in your mesh in these regions, which is likely the phenomena you're observing in the image of your solution that you posted.
RcktMan77 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
sliding mesh problem in CFX Saima CFX 45 September 22, 2015 10:53
Interesting problem: Parallel Processor VOF Fluent + Dynamic Mesh + System Coupling spaceprop FLUENT 5 September 2, 2014 09:43
Importing 2D separated Hybrid mesh from PointWise to Ansys Fluent Masoud.A1 Pointwise & Gridgen 3 April 6, 2014 06:52
FLUENT Not Recognizing That Mesh Has Been Updated tantin FLUENT 0 January 7, 2013 20:01
Moving Mesh Velocity Issue: Mesh velocity does not equal displacement Doginal CFX 2 September 8, 2011 12:02


All times are GMT -4. The time now is 16:41.