CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > STAR-CCM+

DFBI Seakeeping Simulation

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 23, 2012, 05:35
Default DFBI Seakeeping Simulation
  #1
New Member
 
Join Date: Apr 2012
Location: Germany
Posts: 5
Rep Power: 5
Forbin is on a distinguished road
Hi there!

I'm doing a seakeeping simulation with a small container-vessel for a student project and used the "boat in headwaves" tutorial as a guideline. The vessel is allowed to heave and pitch and I use the first order waves. The time-step is set in accordance to the CFL number. The mesh is valid.

Anyway I'm experiencing serious problems concerning my free surface. The free surface - especially the waves - behaves unphysical after some time and the water level in my region starts to rise. At this point the waves are badly scattered. This problem seems not to be connected to the mesh, because a tutor of me solved the simulation on the same mesh with COMET.

I assume that it may be related to the physics models I use and therefore would be glad for any help. The models used are:

- Multiphase Interaction
- Laminar
- Segregated Flow
- Gradients
- Implicit Unsteady
- Segregated Fluid Isothermal
- VOF Waves
- Gravity
- Multiphase Equation of State
- Volume of Fluid (VOF)
- Eulerian Multiphase
- Multiphase Mixture
- Three Dimensional
Forbin is offline   Reply With Quote

Old   May 23, 2012, 09:17
Default
  #2
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 223
Rep Power: 9
ping is on a distinguished road
if your water level is rising it normally means you don't have vof wave inlet field function boundaries on ALL the boundaries other than the pressure outlet (which should have the vof wave hydrostatic field function). ensure you are watching a scalar plot (no smoothing) of volume fraction of water on one or two axial vertical sections to ensure the transition from air to water occurs across only one or two cells, since the iso surface 'hides' problems even though it displays the wave well. try shortening your times step and use 2nd order time is you want the waves to maintain their hieght. need about 20 cells vertical for a wave and 40 per wave length too (use anisotropic mesh refinement to achieve this). overset mesh will allow greater trim angles with a simpler mesh to capture the wave for sea keeping runs since the underlying mesh is stationary.
ping is offline   Reply With Quote

Old   May 23, 2012, 10:05
Default
  #3
New Member
 
Join Date: Apr 2012
Location: Germany
Posts: 5
Rep Power: 5
Forbin is on a distinguished road
Quote:
Originally Posted by ping View Post
if your water level is rising it normally means you don't have vof wave inlet field function boundaries on ALL the boundaries other than the pressure outlet (which should have the vof wave hydrostatic field function).
Thank you ping, that is true. I only use one velocity inlet in front of my ship and one pressure outlet on the back, while the other sides of my region are symmetry planes. So I will change these to be velocity inlets as well...
Forbin is offline   Reply With Quote

Old   May 23, 2012, 11:44
Default
  #4
Senior Member
 
Join Date: Oct 2009
Location: Germany
Posts: 637
Rep Power: 12
abdul099 is on a distinguished road
The water level should not rise due to symmetry planes instead of velocity inlet.

Did you use overlapping grid? Did every time step converge well?
__________________
We do three types of jobs here:
GOOD, FAST AND CHEAP
You may choose any two!
abdul099 is offline   Reply With Quote

Old   May 23, 2012, 11:54
Default
  #5
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 223
Rep Power: 9
ping is on a distinguished road
sorry to contradict you abdul, but the top and bottom boundaries must be vof wave inlet boundaries if rigid body DFBI is being used in a case which has reasonable amounts of trim - Forbin says he/she is trying to replicate the boat tutorial which uses this technique - without this these cases go crazy. the way around this restriction is to use overset mesh when the base region is fixed and then there will be no problems
ping is offline   Reply With Quote

Old   May 23, 2012, 16:48
Default
  #6
Senior Member
 
Join Date: Oct 2009
Location: Germany
Posts: 637
Rep Power: 12
abdul099 is on a distinguished road
ping, you're right. I did not think about top and bottom in an embedded motion case. I just thought about the sides.
So Forbin, forget my last post and listen to ping
__________________
We do three types of jobs here:
GOOD, FAST AND CHEAP
You may choose any two!
abdul099 is offline   Reply With Quote

Old   May 24, 2012, 04:16
Default
  #7
New Member
 
Join Date: Apr 2012
Location: Germany
Posts: 5
Rep Power: 5
Forbin is on a distinguished road
Thanks for your quick response and help. I just started a simulation with the changes you suggested and I'm looking forward for the results...

And actually me is a "he"...
Forbin is offline   Reply With Quote

Old   October 15, 2013, 10:27
Default
  #8
Member
 
Arun Krishnan.L.H
Join Date: Jan 2013
Posts: 74
Rep Power: 4
arun7328 is on a distinguished road
Hello,

Did you get it running? I have the same problem when simulating a regular wave on a cylinder. The cylinder is only allowed to heave and pitch and I have used DFBI motion. It seems that after some time the cylinder sinks down or water level starts to increase. I have used velocity inlet at top and bottom. Any suggestions?

Thanks
Regards
Arun
arun7328 is offline   Reply With Quote

Old   October 17, 2013, 09:36
Default
  #9
New Member
 
Join Date: Apr 2012
Location: Germany
Posts: 5
Rep Power: 5
Forbin is on a distinguished road
Hey arun!

There was no real solution for this special problem. However, I managed to run the simulation correctly after exporting the mesh, followed by an import into a new simulation file. Therefore, I think that my original file was corrupted at some point. I hope this helps!
Forbin is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Solar Radiation in OpenFOAM plainstyle OpenFOAM Running, Solving & CFD 15 July 8, 2014 04:43
Axial fan simulation in UG/NX 7.5 fan123 Main CFD Forum 2 April 23, 2011 08:22
Simulation of a complex wing in solidworks flow simulation niels1900 FloEFD, FloWorks & FloTHERM 6 April 20, 2011 10:44
Why my simulation not agree with the wind tunnel experiment zhaowei CFX 1 March 30, 2011 19:13
strange simulation error Ralf Schmidt FLUENT 2 May 4, 2007 13:02


All times are GMT -4. The time now is 20:07.