CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > STAR-CCM+

Multiple Physics Continua

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By abdul099

Reply
 
LinkBack Thread Tools Display Modes
Old   April 21, 2011, 06:41
Default Multiple Physics Continua
  #1
New Member
 
Matt Walton
Join Date: Mar 2011
Posts: 8
Rep Power: 6
boathead is on a distinguished road
I am trying to set up a conjugate heat transfer model (in the case of the attached image, just a simplified version of the main model). The model has 4 separate regions; the solid plate in the middle, the top box, the bottom box and the tube in the middle. Fluid is supposed to flow through up through the bottom box, through the tube and into the top box where there is a crossflow (left to right).

I am trying to incorporate two separate physics continua, one for the top box and one for the bottom box because I need to specifiy different pressure and viscosity boundary conditions at A and B respectively. At both A and B I am using a velocity inlet as my boundary condition which is why I cannot use one physics continuum.

The problem I am having is that, having created all the necessary interfaces between the fluid and solid regions and the fluid to fluid regions (i.e the top and bottom of the tube with the wall of the top and bottom boxes), when I apply physics continuum 1 to the top box and physics continuum 2 to the bottom box and leave the tube without (or with physics 1 or 2) no physics continuum, (depending on which physics continuum is applied to which region) it will change either the interface at the top (highlighted by the red circle) or bottom of the tube from an internal interface to a baffle which means the fluid will not go through it. I cannot even change it from a baffle back to an internal interface which is frustrating!

Is it possible to have two physics continua in such a case and if so what is the best way to get around the baffle issue.

Cheers
Attached Images
File Type: jpg Baffle.JPG (16.6 KB, 52 views)
boathead is offline   Reply With Quote

Old   April 25, 2011, 04:10
Default
  #2
Senior Member
 
Join Date: Jun 2009
Posts: 100
Rep Power: 8
alastormoody11 is on a distinguished road
Hi,

One thing you could do is set it to a porous baffle and set the porosity to 1 so it will act like an internal interface. this is hardly an elegant solution but if nothing else works you might want to try this out
alastormoody11 is offline   Reply With Quote

Old   April 25, 2011, 08:14
Default
  #3
New Member
 
Matt Walton
Join Date: Mar 2011
Posts: 8
Rep Power: 6
boathead is on a distinguished road
I cannot actually change the interface type at all. I have read in the help manual that the internal interface will not work with a different physics continuum either side of it.
boathead is offline   Reply With Quote

Old   April 28, 2011, 18:09
Default
  #4
Senior Member
 
Join Date: Oct 2009
Location: Germany
Posts: 637
Rep Power: 12
abdul099 is on a distinguished road
I suspect, you don't just have to change the interface types, but set up the simulation the right way. It just sounds weird.
First, you don't have to set up four different regions, put all fluid regions in one. You can set several velocity inlets in the same physics continuum. It DOES work!

Second, it's NOT possible to have several regions with different fluid physics continua connected to each other. Create ONE physics continuum and apply it to ALL fluid regions. All of them will have the same fluid, the same properties, are connected to each other and obey to the same physics - so why do you try to set up TWO physics continua???
TrII4d likes this.
abdul099 is offline   Reply With Quote

Old   April 29, 2011, 06:37
Default
  #5
New Member
 
Sebastian H.
Join Date: Apr 2011
Posts: 7
Rep Power: 6
sebastianh is on a distinguished road
Hi Matt,

you can change the Interface type under the Interfaces main point.
That works in my case. 2 Regions, 2 physic continuums.

It doesn`t work if you change your Interface type under regions.

cheers
sebastianh is offline   Reply With Quote

Old   April 29, 2011, 09:59
Default
  #6
Senior Member
 
Join Date: Jun 2009
Posts: 100
Rep Power: 8
alastormoody11 is on a distinguished road
Hi,

Sorry for the late reply.

If during the course of the simulation you want to keep the density and viscosity of the fluid entering from different inlets as the same and different from each other you will need to perform a multiphase simulation though a bit unphysical this is an easier approach.

If you want that the density and the viscosity of your fluid to change with temperature, which is why i presume you are specifying different properties for the same fluid you will need to create a field function and table and change the property with the solution which will a considerably more involved approach.

If what you want is just initial condition to differ you can do that simply by using a field function, which checks the height of your cell and then assigns the value depending on the location of the cell, use the field function in the pressure tab.

Hope this helps
alastormoody11 is offline   Reply With Quote

Old   December 4, 2011, 13:33
Default
  #7
Member
 
Join Date: Nov 2011
Location: Germany
Posts: 40
Rep Power: 5
TrII4d is on a distinguished road
Hi,

first: sorry for the late reply (but maybe it helps other users ;-))

you're right, when you say:

I have read in the help manual that the internal interface will not work with a different physics continuum either side of it.

so star ccm+ changes the property of the interface to "baffle" ... and this function does not allow the fluid to go threw the interface

what you can do:

make three regions:

region 1: output/input region with physics 1
region 2: copy of the regions, where the fluit has to flow with physics 1
region 3: orginal of the regions, where the fluit has to flow with physics 2

make interface between boundary of region 1 and boundary of region 2 --> in-place interface (cause of the same physics)
Make interace between region 2 and region 3 --> Heat excahnger interface cause of the different physics and the interface between two regions!

at least, you can translate the region 3 to the left or right. than you can see what happens in the simulation.

you can't create interfaces between boundaries of regions, who have different physics!

so you have to copy one regions, give them the same physics, make interfaces an then create a third regions with other physics.

an interface between two regions with different physics in possible.

greetz
TrII4d is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
OpenFOAM static build on Cray XT5 asaijo OpenFOAM Installation 9 April 6, 2011 12:21
physics phD to CFD? jck87 Main CFD Forum 13 October 9, 2010 16:15
Error Message after switching to multi domain physics chili023 CFX 3 June 5, 2010 05:28
How can the physics branch missing in continua Wendy CD-adapco 2 October 30, 2008 16:38
Multiple reference frames? Moon CD-adapco 0 March 4, 2003 07:32


All times are GMT -4. The time now is 14:34.