# Integrating along a streamline

 Register Blogs Members List Search Today's Posts Mark Forums Read

 October 28, 2011, 09:27 Integrating along a streamline #1 New Member   Jeff Join Date: Aug 2010 Posts: 11 Rep Power: 6 Damage to red blood cells in a flow is often evaluated by an equation like this: damage=a*(shear stress)^b * (time)^c where a,b,c are constants. Here, time is the time of exposure at the local value of shear stress. In other words, the idea is to integrate this along a streamline to determine how a particular red blood cell would be damaged. Anyone know how to integrate an expression like this along a streamline in STAR-CCM+? JB

 October 29, 2011, 10:09 #2 Member   Robert Join Date: Jun 2010 Posts: 86 Rep Power: 8 Had you considered doing it as a source term. To find out flight time I think you put in a source term of density (it's in one of the examples). Thus you can see how long it takes to get from the inlet to a point. You should be able to generate a source term which will essentially be the damage incurred while in that cell and the code will integrate it for you. You can also see where the most damage is done purely by plotting up the source term (you may need to normalize by volume). The other option is to run tracks, get the track file format from CD, dump the other data you need and write a program to do it externally.

 November 7, 2011, 06:57 #3 Senior Member   Ping Join Date: Mar 2009 Posts: 223 Rep Power: 9 on a quick think about this, I dont think you need streamlines or the 'age of flow via density' technique mentioned by robertb as used to measure age of air in buildings. you say the damage is time at a certain shear stress, so it would seem to me that you just need a field function which works out the damage during the current timestep = shear stress * dtime (with your constants included of course). then you need to add this to the current sum of damage to get the new total damage locally everywhere in the field. do the sum using a field monitor of type sum. plot this scalar field function. seems simple to me?

 November 7, 2011, 08:49 #4 Member   Robert Join Date: Jun 2010 Posts: 86 Rep Power: 8 This would only provide total damage in the domain. It is likely that to design better parts you will need to attribute local damage to specific features which I do not believe this technique will do.

 November 8, 2011, 04:14 #5 Senior Member   Ping Join Date: Mar 2009 Posts: 223 Rep Power: 9 shear-tracking.jpg ...it is not the total sum (that is a simple sum report) but the sum in each cell - this is why field monitors are such wonderful tools. however on second thoughts this is not what you want - it would tell you where the worst cells for creating damage are in fluctuating flow. Whereas you need the transported damage summed, so you should be using a passive scalar for this: create the field function for your damage variable; add a passive scalar; add a region source for this scalar and use the damage field function as the source for the scalar. to get the units correct your might need to think about it a bit. i did this in a little test and the results are in the image - you can see the local shear stress at the top and the passive scalar below, with high values in the recirculation zone behind as one would expect.

November 8, 2011, 18:57
#6
New Member

Jeff
Join Date: Aug 2010
Posts: 11
Rep Power: 6
Yes, Ping. I think you have the idea that I came upon independently. (Actually, see "Fast three-dimensional numerical hemolysis approximation" by Garon and Farinas, Artificial organs, 2004.) Some people use the streamline approach, but the problem is that it only gives you an answer along the streamlines you happen to select. Also, in order to calculate the residence time, you need to use cell size and the velocity field, and this can be sketchy near the no-slip walls.

So, the preferred approach is to use a passive scalar and then use a source term to generate local damaged protein and then it can convect downstream to other parts of the flow. It's an Eulerian approach vs a Lagrangian approach.

Now the trick of the implementation is to come up with a representative shear stress (tau) for each finite volume cell. The paper suggests a von Mises type of approach. Does anyone know how to extract the stress tensor components in STAR-CCM+? They're not standard outputs.

Thanks for the input!

Quote:
 Originally Posted by ping Attachment 9910 ...it is not the total sum (that is a simple sum report) but the sum in each cell - this is why field monitors are such wonderful tools. however on second thoughts this is not what you want - it would tell you where the worst cells for creating damage are in fluctuating flow. Whereas you need the transported damage summed, so you should be using a passive scalar for this: create the field function for your damage variable; add a passive scalar; add a region source for this scalar and use the damage field function as the source for the scalar. to get the units correct your might need to think about it a bit. i did this in a little test and the results are in the image - you can see the local shear stress at the top and the passive scalar below, with high values in the recirculation zone behind as one would expect.

 November 8, 2011, 19:05 #7 New Member   Jeff Join Date: Aug 2010 Posts: 11 Rep Power: 6 Now that I think about it, the only problem with the above approach is the conservation of red blood cells/proteins. You can generate an amount that exceeds what comes in potentially. I think I might also define another passive scalar representing the undamaged concentration and link the two such that the total damaged concentration cannot exceed the supply of undamaged entering the system.

 November 8, 2011, 19:44 #8 Senior Member   Ping Join Date: Mar 2009 Posts: 223 Rep Power: 9 glad it is looking feasible now. here is a shear stress field function i have used in the past (turn on 'temporary storage retained' in solver): sqrt( mag2(\$\$U_VelocityGrad) + mag2(\$\$V_VelocityGrad) + mag2(\$\$W_VelocityGrad) ) * \$DynamicViscosity bluebase likes this.

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post sunflower FLUENT 0 June 8, 2011 01:48 lionlove0903 OpenFOAM Post-Processing 2 March 14, 2011 16:25 cedric_duprat OpenFOAM Paraview & paraFoam 0 January 12, 2010 04:04 allamarein FLUENT 0 July 9, 2009 20:51 Hong Main CFD Forum 0 May 18, 2000 08:10

All times are GMT -4. The time now is 05:28.