|
[Sponsors] |
October 24, 2016, 05:15 |
2D-Mesh with blocking? possible?
|
#1 |
New Member
Join Date: Mar 2016
Posts: 29
Rep Power: 10 |
Hey,
I tried to do a blocking of my 2D Geometry with HEXA_BLOCK. Unfortunately, I get only 3D hexa blocks (I know, I know, a hexa is 3D. But I hoped to get sth 2D). I want to do it in 2D, to easily vary the thickness and number of elements in the third dimesnion with the TRANSLATE option. (want to use it in OpenFOAM, unstationary simulation). Is it possible to do somehow a blocking of a 2D geometry? Maybe splitting the sourface in "blocks" in my CAD-program, then mesh it with ANSA? Could this work? Thanks in advance Last edited by The_Kaiser; October 24, 2016 at 07:23. Reason: idea for solving |
|
October 24, 2016, 08:28 |
|
#2 |
Senior Member
Vangelis Skaperdas
Join Date: Mar 2009
Location: Thessaloniki, Greece
Posts: 286
Rep Power: 21 |
Hi there,
Indeed ANSA hexablock is meant for 3D meshing. You could of course create these Boxes and only mesh one of their facets only, but I think this is not an efficient approach. I would therefore recommend that you work on the level of geometry in xy plane, and with CUT operations, cut parallelogram patches that you can mesh with MAP QUAD mesh. The functions that you should use for meshing are then: Perimeters>Length, Number and Spacing Have also in mind the function Perimeters Align, which can be used to "copy" a distribution from one perimeter to another. After meshing all macros with map quad mesh, you can, as you write, use Volumes>Extrude>translate in z coordinate and create one cell thickness for OpenFOAM 2D. Remember to use Elements>Vol2Shell>Skin to create shell mesh in the free exposed facets of the created hexa mesh, so that you can assign BCs on them Hope this helps Vangelis |
|
October 25, 2016, 10:17 |
|
#3 |
New Member
Join Date: Mar 2016
Posts: 29
Rep Power: 10 |
Hey,
Thanks for the advise, it works fine so far! A problem comes after using Elements>Vol2Shell>Skin. I get the shell, but the problem is, every mesh element gave me 1 face. So when I have over a milion faces, it's kinda impossible to assign the boundary conditions... Help again please? |
|
October 25, 2016, 10:50 |
|
#4 |
Senior Member
Vangelis Skaperdas
Join Date: Mar 2009
Location: Thessaloniki, Greece
Posts: 286
Rep Power: 21 |
I forgot to mention that for quick selection you should activate the Feature Angle selection tool at the bottom centre of ANSA GUI next to ENT and PID selection. In this way with one click you can pick a whole area within the user specified feature angle (by default 40deg)
Vangelis |
|
October 28, 2016, 06:46 |
|
#5 |
New Member
Join Date: Mar 2016
Posts: 29
Rep Power: 10 |
Works so good. You are like a magician Thanks
|
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
[snappyHexMesh] SHM problem : KVLCC2 with appendage mesh | sc.park | OpenFOAM Meshing & Mesh Conversion | 1 | March 13, 2016 14:28 |
[mesh manipulation] Importing Multiple Meshes | thomasnwalshiii | OpenFOAM Meshing & Mesh Conversion | 18 | December 19, 2015 19:57 |
3D Hybrid Mesh Errors | DarrenC | ANSYS Meshing & Geometry | 11 | August 5, 2013 07:42 |
[ICEM] Problem making structured mesh on a surface | froztbear | ANSYS Meshing & Geometry | 4 | November 10, 2011 09:52 |
fluent add additional zones for the mesh file | SSL | FLUENT | 2 | January 26, 2008 12:55 |