CFD Online Discussion Forums

CFD Online Discussion Forums (
-   ANSYS Meshing & Geometry (
-   -   [ICEM] Some 2D Mesh come out in my 3D model,anyone can help me? (

realstoneman May 14, 2012 11:12

Some 2D Mesh come out in my 3D model,anyone can help me?
2 Attachment(s)
everybody,as my title,my model is 3D,but when I created mesh by ICEM CFD,there exists some 2D mesh,which you can see from the attachments.
Thanks a lot in advance~Please explain the weird phenomenon in detail,I make the same mistake many times!

Far May 14, 2012 11:20

attach model

realstoneman May 14, 2012 11:22

I will send a email to you,attachment is 300K,beyonds the limit

PSYMN May 15, 2012 10:02

Why do you think those are 2D elements? They look like very squished 3D elements to me.

However, your image doesn't provide enough info for me to diagnose more than that.

realstoneman May 15, 2012 10:16

Thanks for your reply.May I have your email?I will send you my model.

PSYMN May 21, 2012 16:27

1 Attachment(s)
Hey Stone Man,

I finally took a look at this. The only issues I found using "Check Mesh" were single edges and multiple edges. These were both the result of your construction surfaces and are not causing you any troubles as long as you set up those construction parts properly in the solver (or delete the shells before sending them tot he solver).

The single edges are because a particular face was not actually associated to the Fuzhuwai part... You probably just missed it... You can fix it or not depending on how you plan to use that surface in post processing...

The multiple edges were just where these construction surfaces met the Outlet.

Next, I looked at quality and found the elements you were concerned about... Looking closer I could see that they were hexa elements, just very squished thin... On one side, they were almost zero thickness (pretty much like a very thin wedge). The edge parameters didn't explain this, so I thought maybe there was a geometry issue or something like that (sorry, I didn't take the time to really figure out what was wrong with the model).

The easiest way to walk over geometry issues at this scale is to go into Settings => Meshing Options => Hexa Mixed => Projection Limit.

The initial spacing there was about 0.02, so I set the projection limit to 0.05... This basically allows nodes within that distance of an edge to be linearly interpolated instead of projected...

That solved the problem immediately and brought min quality up to >0.25. The remaining elements have more standard problems, but your solver can probably handle the hexa mesh at that quality.

realstoneman May 21, 2012 22:13

Thank you very much,
you explain it clearly.and I should be more patiently in associating the edges and surfaces. the fatal error comes from the edge and surface association,actually,I find out some edge and surface which I missed,as you's really appreciate and thanks a lot.

All times are GMT -4. The time now is 14:08.