CFD Online Discussion Forums

CFD Online Discussion Forums (
-   ANSYS Meshing & Geometry (
-   -   [ICEM] Mesh unable to follow curved geometry (

Ananthakrishnan June 5, 2012 04:47

Mesh unable to follow curved geometry
I am trying to mesh a wing with sinusoidal leading edge..
My problem is that the mesh does not follow the profile of the leading edge UNLESS i give very high bunching as seen near the tip of the wing below..

As you move towards the root of the wing, the mesh is less concentrated and it does not follow the profile..

I need a way to make the mesh follow the profile inspite of lesser number of nodes( currently the node spacing near the root is 0.002 and if i have such spacing throughout the span, total elements become more than 10 million which is not reasonable for me..)

The above link contains the block and tin files


Far June 5, 2012 05:03

try option project to b-spline.

Ananthakrishnan June 5, 2012 05:19

i tried it and i dont see any changes :(( ..
let me upload the .blk and .tin files..

Ananthakrishnan June 5, 2012 05:37

the block and tetin files are available in the above URL..

@far..To use project to b spline option, i just need to select it and "apply" right?? after this if i recompute the pre mesh i dont see any changes...

PSYMN June 6, 2012 14:52

It is clear that your mesh size along the wing is larger than the features you are trying to capture... You will need much finer mesh (increase the number of nodes) along the wing...

Ananthakrishnan June 7, 2012 02:17

If i try to capture the features by just increasing the nodes, then the mesh size increases drastically (around 8 million). It is practicably not feasible for me at all..
Is there any other way to do it??

PSYMN June 7, 2012 13:57

You may be able to increase the resolution in that area without increasing everywhere (either with clever topology, or with refined blocks (hanging nodes), sub models, or other methods), but you can't expect to capture that trailing edge with mesh that is coarser than the edge...

Ananthakrishnan June 9, 2012 06:48

Thanks a lot..i was able to create the hanging nodes by mesh refinement but the nodes are not getting projected onto the curves..
I have switched on the "project to B splines" option as well..any ideas??

diamondx June 11, 2012 15:09

hello ananthakrishnan,

did you consider a mix of hexa and tri. i tried and ended up with 3M node like the picture above. may be you will need a more refined mesh depending on you flow around the wing.
I attached the project, file size is 150 Mb because of the *.*uns file. What is your computer specs ? can you handle opening 5M-6M. let me know if you can, then you can set up a case file, then share it with me, i can help you perform calculation on a cluster (big cluster i have access to).

the project file:

Far June 11, 2012 15:10

how did u make the hybrid meshing?

diamondx June 11, 2012 15:15

i made a small box around the airfoil, i named all the surfaces of the box "interface". then i meshed inside of the box using blocking and outside of the box with unstructured and giving a very small size to the tri element next to hexa so the merging process can be done well, after that i went to mesh and merged the two of them and selected "interface" as the common part.

Far June 11, 2012 15:19

both meshes need to be identical at interface? If yes, how to ensure this?

diamondx June 11, 2012 15:29

yes they have to be identical, regarding what ? size, i use the measure distance to calculate length of a hexa element. then i copy that length in the tri size.
That's the only way i found and the only way i know for merging two meshes. Then i trust the program in the merging process to do the adequate change in size and merging the node .
Please let me know of another trustful way.

Far June 12, 2012 02:35

wavy wall
See this type of topology advance toplogy , Refer to Fig. no. 5d and 5e. Although it is different software, but still you can idea how to proceed without increasing the mesh size.

Ananthakrishnan June 12, 2012 03:26

thats awesome..sorry i was not able to reply immediately (damn exams)...Thnaks for the cluster man...seriously...let me put my comp to acid test first...
tried the hybrid mesh but wasnt sure about the merging at the interface..i ended up having two sets of nodes at the interface one each for structured and unstructured(even though the size was matching)

i am thinking about "merge sheet with block" option...

Far June 12, 2012 04:23

delete line elements at interface (as suggested by Simon as I remember)

Ananthakrishnan June 14, 2012 05:58

Thanks to all i was able to get a decent mesh..But as of now i am unable to merge the two meshes.

What option should i use in "merge nodes" for merging the two meshes.
I initially thought if i create the unstructured mesh by using the existing mesh on the surface of the interface, then the two meshes are automatically merged!!!

diamondx June 14, 2012 14:20

are you using icem 14 ? can't open your project
in merge nodes, select merge meshes, leave the default setting and select the surface that the tri and the hexa has in common in the "merge surface mesh parts"

diamondx June 14, 2012 14:40

ok no it's version 13. but when i open the project everything disappear. can you open it and dismiss the scan plane operation then save it again ? thanks

Ananthakrishnan June 14, 2012 15:01

done..It should be working now

All times are GMT -4. The time now is 19:05.