CFD Online Logo CFD Online URL
Home > Forums > ANSYS Meshing & Geometry

[ICEM] about hybrid meshing

Register Blogs Members List Search Today's Posts Mark Forums Read

LinkBack Thread Tools Display Modes
Old   October 29, 2013, 12:00
Default about hybrid meshing
New Member
Join Date: Oct 2013
Location: essen, germany
Posts: 1
Rep Power: 0
muralikiran85 is on a distinguished road
Send a message via Skype™ to muralikiran85
Hi all,
I am a master student doing my thesis in icem cfd. I need to do hybrid meshing(structured and unstructured). I got a link ( regarding it. while doing it accordingly i got problem in merging nodes. can anyone help me in hybrid meshing. if possible can anyone explain me the procedure in detail, about how to do hybrid meshing.

Warm Regards
Muralikiran Krishnakumar
muralikiran85 is offline   Reply With Quote

Old   October 29, 2013, 19:06
Senior Member
Join Date: Feb 2013
Location: Germany
Posts: 186
Rep Power: 16
kad will become famous soon enoughkad will become famous soon enough
The process of hybrid meshing is described pretty accurate in your link. The most important points of hybrid meshing are equal mesh sizes and quad aspect ratio near 1 on the interface. Heres how I do it:

1) Create two separate geometries from the original geometry. one for hexa one for unstructured. I usually choose the interface to be plain. Further there are no prisms allowed on the interface. So I put it in location that allows to use prism for most of the unstructured part. The most obvious spot for the interface is not always the best. There can also be other restriction like wall distance. For geometry preparation Design modeler is very useful.

2) Create hexa mesh for hexa part with respect to restrictions above and save it as xxx.uns.

3) Create unstructured mesh via Octree -> delete volume ->smooth surface -> Delaunay -> smooth volume -> prism. Smoothing has a huge effect on prism generation. Laplace smoothing gives you a very uniform distribution. So it might also have a positiv effect on the tri mesh at the interface. For elements with quality under 0.3 or 0.4 you can use the normal smoother as it aims for individual quality.

4) Open hexa mesh and hit merge. Btw. a geometry is not required for the further proceeding.

5) Merge hexa and tet under merge nodes ->Merge volume meshes. The surface mesh at the interface has to be in the same part e.g. "interface". Select it and apply.

6) Check mesh to identify any errors. Multiple edges should be reported at the interface.

7) Delete shell elements of the interface. Check again. This should give you no error when both volume meshes where in the same part e.g. fluid.

8) Smooth volume mesh again for better quality near the interface.

I have successfully applied this method many times over the last few weeks myself. It actually worked every single time. The only problem that occured were some wrong associated shell elements near the interface. These can be easily assigned manually to the right part.

Last edited by kad; October 29, 2013 at 23:25.
kad is offline   Reply With Quote

Old   October 30, 2013, 04:52
Join Date: Nov 2011
Location: Czech Republic
Posts: 95
Rep Power: 7
Sixkillers is on a distinguished road
Also take a look at tutorial called "Merged Tetra-Hexa Mesh in a Hybrid Tube" in ANSYS ICEM CFD Tutorial Manual. You might find it useful.
Sixkillers is offline   Reply With Quote

Old   January 21, 2015, 19:15
Join Date: Jul 2012
Location: Wisconsin,USA
Posts: 34
Rep Power: 7
AA29 is on a distinguished road
Hi guys,

I have a hex and tet mesh and want to merge these two meshes to make one volume mesh(or region) WITHOUT the shell elements at the interface.
I am trying to follow the steps mentioned by kad, but still once I merge the volume mesh, I works ok without errors. I can see pyramids as they should be at the interface, but the shell elements are still there. If i delete the shell elements and do checkmesh i get the error of missing internal faces.

Am i missing something here?

AA29 is offline   Reply With Quote

Old   February 16, 2015, 04:47
Join Date: Apr 2014
Posts: 67
Rep Power: 5
adi.ptb is on a distinguished road
Can anyone tell me what are the steps in meshing quad/tri in 2d geometries?
adi.ptb is offline   Reply With Quote


icem cfd hybrid meshing

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] Hybrid meshing close to surface k.vimalakanthan ANSYS Meshing & Geometry 14 October 18, 2012 23:20
[ANSYS Meshing] Hybrid 2D Meshing stanabng ANSYS Meshing & Geometry 1 July 20, 2012 16:27
[ANSYS Meshing] Hybrid meshing ICEM djoul ANSYS Meshing & Geometry 2 January 17, 2012 19:18
[ANSYS Meshing] 2D airfoil hybrid meshing help! gusdlsrb ANSYS Meshing & Geometry 0 March 27, 2011 15:31
hybrid meshing for 3D wing Angela Bong Main CFD Forum 0 March 17, 2006 09:13

All times are GMT -4. The time now is 18:47.