CFD Online Logo CFD Online URL
Home > Forums > Software User Forums > ANSYS > ANSYS Meshing & Geometry

[ANSYS Meshing] Solution to periodic boundary problem

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree4Likes
  • 4 Post By SophieLee

LinkBack Thread Tools Search this Thread Display Modes
Old   May 16, 2017, 16:06
Post Solution to periodic boundary problem
New Member
Join Date: Feb 2014
Posts: 1
Rep Power: 0
SophieLee is on a distinguished road
Recently i am working on a geometry which requires rotational periodic boundaries. I have encountered some problems and hopefully this will help those who have similar problems.

1. After I have done the mesh which is a combination of structured and unstructured mesh. The geometry is split into several different bodies to have better control of the mesh.The structured mesh was done using 'Multizone' and unstructured mesh for complicated regions was done using tetrahedron. I then exported the mesh and read it into Fluent. When I tried to make periodic boundaries. Fluent give me an error: Failed to make zones periodic. Error: #f. In my case, I think it means that those two periodic zones do not have the identical mesh.

2. Then i went back to Ansys Workbench mesher. Tried to apply 'Match Control' on the faces in the unstructured mesh region. It failed. The problem is I have to create a new cylindrical 'Coordinate System' becasue the axis of rotation for my geometry is not 'Z' axis. For the new coordinate system, I have to set the principal axis is 'Z' which is defined by the global X axis. And more importantly to set the orgin to (X=0, Y=0, Z=0). Otherwise it won't work. Then set up the 'Match Control' using this new coordinate system.

3. After the mesh is done with the modifications, the mesh export was failed giving the error: The meshing translation to fluent failed due to non-matching periodic nodes. The solution to this is to create a 'Symmetry' folder under the 'Model' tree and then insert 'Periodic Region' and select two set of periodic zones. The reason for this is because I have split the geometry into many bodies and one periodic zone is consisted of several small faces. I need to generate the mesh again after this modification and the mesh export was successful. When the mesh has been read into Fluent. The periodic boundary is already there and no need to set it up in Fluent.

Hope this will help and save some time for people who are having similar problems.
ArturM, jumaah, clarice and 1 others like this.
SophieLee is offline   Reply With Quote

Old   June 28, 2017, 02:51
Omar jumaah
Join Date: Jan 2016
Posts: 35
Rep Power: 9
jumaah is on a distinguished road
well done, in addition to that failed to make periodic zone when the rotation axis direction is wrong in the cell zone. hope it will help
jumaah is offline   Reply With Quote


Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
Radiation in semi-transparent media with surface-to-surface model? mpeppels CFX 11 August 22, 2019 08:30
Basic Nozzle-Expander Design karmavatar CFX 20 March 20, 2016 09:44
An error has occurred in cfx5solve: volo87 CFX 5 June 14, 2013 18:44
Low Mixing time Problem Mavier CFX 5 April 29, 2013 01:00
Problem with periodic boundary layers Phil FLUENT 15 October 2, 2000 15:56

All times are GMT -4. The time now is 06:36.