|
[Sponsors] |
July 21, 2010, 12:15 |
3D blocking with a 2D surface inside
|
#1 |
Senior Member
AB
Join Date: Sep 2009
Location: France
Posts: 323
Rep Power: 21 |
Hi,
I created a 3D blocking for my model, and there are 2D surfaces inside it. Those surfaces are solids and are inside the fluid domain. I splitted my blocks all around those surfaces and associated the edges to the curves. But, when I pre-mesh the model, the surfaces aren't meshed, they are assigned to the fluid part. How can I solve this? I thought about associated the surfaces to the faces of the blocks, but those surfaces are in contact with 2 faces, so I didn't which one I should choose. Thanks for your help, |
|
July 22, 2010, 05:31 |
|
#2 |
Senior Member
AB
Join Date: Sep 2009
Location: France
Posts: 323
Rep Power: 21 |
Associated one of the faces of the blocks around the the 2D part with the surface worked well. The 2D surface is well meshed.
The index control is very useful for this operation! |
|
July 22, 2010, 11:31 |
Face to Part...
|
#3 |
Senior Member
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,663
Blog Entries: 1
Rep Power: 47 |
Glad you figured it out... For the benefit of others let me explain...
In Hexa if you have the same block material on both sides of a face, the default is no projection and no shells. Even if you associate the perimeter edges to curves, the face default is still unassociated. If you have a different material on the other side, the default is to associate face to the nearest surface. ICEM CFD hexa assumes you will have a surface between blocks of different materials. Some users may have blocks in different materials for other reasons (porus media or just to separate various fluid regions for display/modeling purposes), but without intent for actual walls between them. You can handle this with the Face to surface option for shared walls. it will let you pic whole blocking materials and decide the default between them. In your particular case, you just had a zero thickness surface between blocks of the same material and needed to override the default (not projected). The fix is just to go into "Associate Face" and manually override with a new association to nearest or even a particular part. If you have two superimposed surfaces, it is probably better to pick one part so the mesh comes out consistent. |
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
[Gmsh] Error : Self intersecting surface mesh, computing intersections & Error : Impossible | velan | OpenFOAM Meshing & Mesh Conversion | 3 | October 22, 2015 11:05 |
[Gmsh] Problem with Gmsh | nishant_hull | OpenFOAM Meshing & Mesh Conversion | 23 | August 5, 2015 02:09 |
[Gmsh] boundaries with gmshToFoam | ouafa | OpenFOAM Meshing & Mesh Conversion | 7 | May 21, 2010 12:43 |
meshing F1 front wing | Steve | FLUENT | 0 | April 17, 2003 12:37 |
CFX4.3 -build analysis form | Chie Min | CFX | 5 | July 12, 2001 23:19 |