# Can't connect volumes in Gambit

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 October 17, 2011, 19:14 Can't connect volumes in Gambit #1 Member   vlg Join Date: Jul 2011 Location: My home :) Posts: 81 Rep Power: 11 Good day, everybody. I had build the model in Gambit, that consists of 12 spheres. These spheres intersect with each other (figure 1 doesn't demonstrate intersections, it shows a critical case when spheres only touch each other). Since intersections of spheres are circles, there are circle apertures beetween spheres. I had build central sphere with 12 apertures, then, i've needed to copy this elementary cell in twelve direction (volume->copy). When I copy this object, some apertures have to match, forming only one face instead two aperture faces. They do match in Gambit, but I have to connect them (Face->connect). When trying to connect some of this faces, I have warn message: "The call to connect on list of faces resulted in no actual operation" and no change takes place. It appears because of edges of apertures (they have the same coordinates) have different basic vertices (that marked green by default - I use Gambit 2.3.16). How can I connect faces (I must have only one aperture face on each intersection to let fluid flow between spheres. I'm just a beginner in CFD , I've spent a lot of time trying to solve the shown problem, and would be glad for any advice. John.

October 18, 2011, 00:45
#2
Super Moderator

Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 3,239
Rep Power: 34
Quote:
 Originally Posted by villager I must have only one aperture face on each intersection to let fluid flow between spheres.
So I assume spheres are solid elements around which you may let fluid flows.
I would suggest you to create all your spheres, move them at their right places (don't be disrupted by intersection).
Once everything is right placed, just unite all your volume.
Be sure all your volumes are real else the boolean operation won't be successfull.
Now you just need to create your outer domain, and substract the volume with your spheres from outer domain.
__________________
In memory of my friend Hervé: CFD engineer & freerider

 October 18, 2011, 05:24 #3 Member   vlg Join Date: Jul 2011 Location: My home :) Posts: 81 Rep Power: 11 No, I want to let fluid flow through apertures of spheres as shown in this screenshot On this figure flow is allright, because of united volumes. But I need to calculate volumetric flow rate throw the apertures of central sphere. If I unite volumes, aperture faces are deleted and I can't calculate flow rate. So I don't need to unite volumes, I must connect duplicate (superposed) faces. Without connecting fluid doesn't flow (Gambit specifies these duplicate faces as wall. If I retain them, but manually set them to the interface type, Fluent doesn't solve because of error: " Cannot change interior.x to interior because there is only one adjacent cell thread". So I decided to connect faces, using these advices: http://www.cfd-online.com/Forums/flu...ll-thread.html http://www.cfd-online.com/Forums/flu...c-problem.html) I can't connect superposed faces if they have different basic vertices (Gambit automatically creates these vertices at circular edges of apertures when I cut off spherical segments with planes). Is there any solution? Thanks.

 October 18, 2011, 05:39 #4 Super Moderator     Maxime Perelli Join Date: Mar 2009 Location: Switzerland Posts: 3,239 Rep Power: 34 ok so you want to compute flow within spheres an through apertures. Unite all your spheres >> you will have just one volume. Then for each aperture, create the surface by selecting the edge(s) forming your aperture. Then split the volume with the surface. (check that you get one isolated sphere) Then repeat to next aperture, etc... Regarding BC: since splits separate connected volume, your apertures will disappear in fluent BC-lists, since they belong to fluid domain. Nevertheless you can enforce Gambit to affect them with internal or interior BC (don't rember which you have to select) and then you should be able to pick them in Fluent BC Panel villager likes this. __________________ In memory of my friend Hervé: CFD engineer & freerider

 October 18, 2011, 17:10 #5 Member   vlg Join Date: Jul 2011 Location: My home :) Posts: 81 Rep Power: 11 That has helped me! Thank you very much for advice, for spending time answering me!

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Bharath FLUENT 4 October 30, 2006 21:24 Marion FLUENT 4 April 12, 2006 11:58 Andres D. Ortiz FLUENT 0 October 7, 2001 19:17 Ashutosh FLUENT 5 February 21, 2001 01:59 christof FLUENT 1 March 9, 2000 18:03

All times are GMT -4. The time now is 15:51.

 Contact Us - CFD Online - Privacy Statement - Top